Need Help! Threading full depth i one cut OSP5020L


Results 1 to 11 of 11

Thread: Threading full depth i one cut OSP5020L

  1. #1
    Registered
    Join Date
    Jan 2009
    Location
    sweden
    Posts
    25
    Downloads
    0
    Uploads
    0

    Default Threading full depth i one cut OSP5020L

    Hello.

    This is propably very basic but I have not yet found a way.

    I want to cut at thread in only one cut, for example to remove burrs after a finish cut or add some extra threading passes because of deflection whitout having to go thru the intire cutting cycle.
    Is there a easy way to do such thing in the One Touch IGF?

    Thanks!

    Best regards

    Samuel.

    Similar Threads:


  2. #2
    Registered broby's Avatar
    Join Date
    Apr 2006
    Location
    Australia
    Posts
    812
    Downloads
    0
    Uploads
    0

    Default Re: Threading full depth i one cut OSP5020L

    Probably need to use a G33 thread cutting cycle.This code will allow you to program the X axis position i.e. one cut pass.Since I don't have a manual handy at the moment, you will need to look up your own.



  3. #3
    Registered
    Join Date
    Feb 2011
    Location
    usa
    Posts
    223
    Downloads
    2
    Uploads
    0

    Default Re: Threading full depth i one cut OSP5020L

    if you are using the g71 for threading i would try something like the code below

    G71X.750Z-.250B60D.011H.011J48F1

    I would make d and h the same numbers and omit the u to avoid the second pass
    also make the rpm and stating point the same for your deburring pass



    d= depth of cut in the first thread cutting cycle (expressed in dia.)
    u= finishing allowance (expressed in dia. no finishing is performed if u is omitted )
    h= thread height (expressed in dia.)



  4. #4
    Registered deadlykitten's Avatar
    Join Date
    Jun 2015
    Location
    Antarctica
    Posts
    2462
    Downloads
    0
    Uploads
    0

    Default Re: Threading full depth i one cut OSP5020L

    hello vesene, just like broby said, pls check attached about g33 + more goodies

    if you are going to use g33 after another threading code, be sure to use same rpm ( just like rcs60 said ); this involves both codes to use the same start spindle phase

    you may achieve custom infeed paterns by changing start_Z or Q

    it may be possible to use also G71 with custom parameters, just like rcs60 said, but so far i have not tried this ...

    if you are going to use a custom G71, you may simply copy-paste the threading operation inside igf, and edit the copy; for g33 you will need to insert a g-code sequence, and write the code inside it

    remove burrs after a finish cut or add some extra threading passes because of deflection whitout having to go thru the intire cutting cycle
    if you wish, pls specify what kind of burrs you wish to remove :
    ... near end or start of thread
    ... after last pass
    ... ocasional burrs, among intermediate passes ?

    sometimes, a bigger insert may behave better then a smaller insert ... just saying, i don't know your setup

    if you wish, i may give you a code sample / kindly

    Attached Files Attached Files
    Ladyhawke - My Delirium, https://www.youtube.com/watch?v=X_bFO1SNRZg


  5. #5
    Registered
    Join Date
    Jan 2009
    Location
    sweden
    Posts
    25
    Downloads
    0
    Uploads
    0

    Default Re: Threading full depth i one cut OSP5020L

    Thanks for the replies. I will try this out.
    It is mostly for situations with deflection this will be needed in my case.
    Is there maybe a way to add finish passes inside the G71? So that the insert cuts att full depth x number of times? That would be the most efficient I think.

    Best regards
    Samuel.



  6. #6
    Registered
    Join Date
    Feb 2011
    Location
    usa
    Posts
    223
    Downloads
    2
    Uploads
    0

    Default Re: Threading full depth i one cut OSP5020L

    I wold say that you could only get a single final pass but you could put in a u of .0001 to get 2 passes
    otherwise i would use G33 for the thread and use the last g33 multiple times



  7. #7
    Registered deadlykitten's Avatar
    Join Date
    Jun 2015
    Location
    Antarctica
    Posts
    2462
    Downloads
    0
    Uploads
    0

    Default Re: Threading full depth i one cut OSP5020L

    hello again experiment a bit with G71, so to make it deliver only a single cut / one shot / spring pass, etc

    also G33 will do it

    for situations with deflection
    try a lower rpm ?!

    i recently had to deal with threading at increased distance from the chuck, without tailstock

    check this code :

    Code:
        CALL OQ***   V08 = 05 V10 = 0
        CALL OQ***   V08 = 00 V10 = 0.008
    ... V08 : doc
    ... V10 : start_z_shift / phase_shift, etc

    code represents last 2 passes :
    ... penultimate is cutting 0.05
    ... last one is going on same X ( spring pass ), but it is shifted 8um among Z

    if tuned nice, this trick reduces cutting forces ( insert will cut only on one side, and not on both ), and it may allow finish passes without deflection, even if there is deflection on rough passes

    it is kind of a custom infeed, that enlarges the thread section, but is all ok as long as the shape is within tolerances

    kindly

    Ladyhawke - My Delirium, https://www.youtube.com/watch?v=X_bFO1SNRZg


  8. #8
    Registered OkumaWiz's Avatar
    Join Date
    Apr 2009
    Location
    United States
    Posts
    1049
    Downloads
    0
    Uploads
    0

    Default Re: Threading full depth i one cut OSP5020L

    I think you can do it in IGF by making H=D, setting U=0 and using M74 infeed pattern.

    Otherwise RCS60 is on the right track for outside of IGF.

    Experience is what you get just after you needed it.


  9. #9
    Registered deadlykitten's Avatar
    Join Date
    Jun 2015
    Location
    Antarctica
    Posts
    2462
    Downloads
    0
    Uploads
    0

    Default Re: Threading full depth i one cut OSP5020L

    hello threading with a single cut does not require infeed pattern

    but, if you use a threading code without infeed pattern, and after that you repeat threading with different patterns, will the real thread remain the same ? like this, all threading codes ( regardless of using an infeed pattern, or number of passes ), should have the last pass ( finish pass ) syncronized; i never tested this, but i suppose it works this way

    by using G33 i always know how much spindle phase deviation is required for each pass when using a custom infeed; to achieve a spring pass, with G33, i recall last spindle phase + doc=0; i can also control the angles from attached image :
    ... 1st angle will shift Z start position, with major effect on threads with pitch > classical_z_safe position ( if you use Z2.5 on a thread with pitch>2.5, last passes may encounter a shock )
    ... 2nd angle will shift Z end position, with major effect on threads without relief ( if that angle is too tilted, because of a custom infeed pattern, it will add stress to the insert near thread end; this can be managed )

    at the begining, it was harder and more time consuming then writing a G71, but with proper tools, it is faster it is full control



    however, i will try to test if G71 can deliver a single cut / kindly

    Attached Thumbnails Attached Thumbnails Threading full depth i one cut OSP5020L-01-png  
    Ladyhawke - My Delirium, https://www.youtube.com/watch?v=X_bFO1SNRZg


  10. #10
    Registered deadlykitten's Avatar
    Join Date
    Jun 2015
    Location
    Antarctica
    Posts
    2462
    Downloads
    0
    Uploads
    0

    Default Re: Threading full depth i one cut OSP5020L

    Quote Originally Posted by OkumaWiz View Post
    I think you can do it in IGF by making H=D, setting U=0 and using M74 infeed pattern
    hello mr Wizard yup, it works; same for M75

    M73, which is default, always uses fix amounts like D/2 D/4 and D/8, while M74 and 75 don't use such fix amounts

    however, even if G71 M74 or G33 is used, in both cases, is needed a G-code sequence inside igf, or to edit the min file

    Quote Originally Posted by vesene View Post
    I want to cut at thread in only one cut, for example to remove burrs after a finish cut or add some extra threading passes because of deflection whitout having to go thru the intire cutting cycle
    hello again vesene

    it seems like you are looking for a way to fix something that is not delivered properly by the default cycle

    it means that a default threading cycle may fail, but the solution to fix it will always work

    so why continuing using the default cycle ?

    if such situations will repeat, one day, you may need a different approach / kindly

    Last edited by deadlykitten; 11-27-2018 at 02:40 AM.
    Ladyhawke - My Delirium, https://www.youtube.com/watch?v=X_bFO1SNRZg


  11. #11
    Registered deadlykitten's Avatar
    Join Date
    Jun 2015
    Location
    Antarctica
    Posts
    2462
    Downloads
    0
    Uploads
    0

    Default Re: Threading full depth i one cut OSP5020L

    hello, i recently had to deal with some parts with 3-10 leads, that where programmed in igf, and there was a need to run a few more finish-passes

    so i remembered this thread, and i compared these 2 codes :

    Code:
    // spring pass using G71 :
    G71 X192.30 Z-170 H D0.2 U0.04 B60 F M22 M73 M33
    G71 X192.26 Z-170 D3 H3 F M74 G95
    
    // spring pass using G33 :
    G71 X192.30 Z-170 H D0.2 U0.04 B60 F M22 M73 M33
    G33 X192.26 Z-170 F G95
    
    both of them work; only that G33 is shorter, while G71 requires adding D H & M74

    and there is another thing, which makes an important difference : if you wish to cut some spring passes only on the 2nd lead, thus to jump over the 1st lead, then you may use G33 C36, or G71 & Z_start_shift = pitch ( of course, also G33 will work if Z_start is shifted )

    when there are many leads, trying to cut a spring pass on the last lead, using G71, will change your Z_start with an important value, leading to time loss ( cutting air ), or to a clearance that will crash the tailstock

    a nice thing about G33 is that it allows changing the spindle phase, while G71 can not do that

    this operation was long, material was tough, and there was a big chance to have the insert broken after a few leads, making it impossible to continue, so i started by cutting at doc1 all leads, then increasing the doc across all leads, and so on, so, instead of finishing the leads one-by-one, i finished them all together

    using G33 is harder then using G71, especially for infeed patterns, so maybe is ok to have a piece of software to help you

    in the end, G33 will always do what G71 does, will perform faster on any infeed patern because it can keep same z_start, it can deliver custom infeeds, + other things / kindly

    Ladyhawke - My Delirium, https://www.youtube.com/watch?v=X_bFO1SNRZg


Tags for this Thread

Posting Permissions

  • You may not post new threads
  • You may not post replies
  • You may not post attachments
  • You may not edit your posts
  •  


About CNCzone.com

    We are the largest and most active discussion forum for manufacturing industry. The site is 100% free to join and use, so join today!

Follow us on


Our Brands

Threading full depth i one cut OSP5020L

Threading full depth i one cut OSP5020L