set zero point when processing small series

[strokerace]

Hello
I have a little problem: I want to process small series and I want to write into the program that each work piece should be measured again.

I have a fixed block where I dock my work pieces. It’s a flame-cut part and about 40mm thick, around 400x400 and in the middle is a hole around 200x200 that I need to mill to 202x202. The midpoint should be positioned in the middle of the flame cut part.

So, how do I program it, so that the machine (HEDELIUS CB80 itnc530) always gets the sensing device after the start up, then touches the squared hole in the middle, and then gets the cutter and start milling afterwards.

So far I only ever had 1-4 of these flame cut parts to mill and I re-calibrated each part-but manually, now I wanted to automate this process. I know that it’s possible but I don’t know how!

Many thank for any help
Regards

[rene1234]

Hello
That should work with “Touch Probe 411”. So on the controller touch probe, then zero point and then on the 411.

Regards
rené

[roadrunner2]

0 BEGIN PGM xxx MM
1 TOOL CALL 1 Z
2 L X+0 Y+0 Z+10 R0 FMAX
3 TCH PROBE 410 REF POINT SQUARE INSIDE ~
Q321=+0 ;MIDDLE 1. AXIS ~
Q322=+0 ;MIDDLE 2. AXIS ~
Q323=+200 ;1. SIDE-LENGHT ~
Q324=+200 ;2. SIDE-LENGHT ~
Q261=-10 ;MEASURING HOLE ~
Q320=+0 ;SAFETY DISTANCE. ~
Q260=+10 ;SAFE HOL S. HOLE ~
Q305=+0 ;NO. IN TABLE ~
Q331=+0 ;REFERENCE POINT ~
Q332=+0 ;REFERENCE POINT ~
Q303=-1 ;MEASURED VALUE TRANSFER ~
Q381=+0 ;TOUCH TS-AXIS ~
Q382=+0 ;1. KO. FOR TS-AXIS~
Q383=+0 ;2. KO. FOR TS-AXIS ~
Q384=+0 ;3. KO. FOR TS-AXIS ~
Q333=+0 ;REFERNCE POINT
4 TOOL CALL 2 Z S2000
5 ...
6 ...
7 ...
8 END PGM xxx MM

But I guess you figured it out by yourself...