Doosan Fanuc 31i G65 Macro to G code cycle issue

[gavintwopies]

Hi,

starting to find more and more issues around this 31i panel that i have never encountered on older fanuc panels when writting custom macro cycles.

So in short i have created a custom macro G13 cycle to allow me to use some proven Haas programs we have had in use for a no. of years to save rewriting the same programs again.

so at present im having to call the program via:

ie:

G65 P9013 I50. Z-1. D20 F500.

so at present still have to edit up the HAAS pgms instead of calling

G13 I50. Z-1. D20 F500.

i have gone down the usual procedure of setting the G-code name into parameter #6053 to call pgm O9013

but it refuses to accept the G13 code...

i have also tried this as another no. so called it O9019 and used #6059 for the G13 call again it will not accept the command.

Has something else been changed within the 31i software over the older 16M/18M/21i panels that i have not encountered until now?

Similar Threads:

• Need Help!- DOOSAN PUMA 240 MACRO CODE
• Doosan/Daewoo HM800 tool changer macro Fanuc 18i-m
• Fanuc Macro and G-Code Programming

[soymilk]

I don’t know what to tell you, I just did this to my doosan mill right now and it works. It’s a 31i model b controller

Which controller do you have exactly?


I made an empty O9013 program with a bunch of eob and a m99 at the end.

Put 13 into 6053 Param

Went to mdi and put g13 and single block and it switched to program 9013

[gavintwopies]

I don’t know what to tell you, I just did this to my doosan mill right now and it works. It’s a 31i model b controller

Which controller do you have exactly?


I made an empty O9013 program with a bunch of eob and a m99 at the end.

Put 13 into 6053 Param

Went to mdi and put g13 and single block and it switched to program 9013

The panel is series 31i - model A its on a 2013 doosan hp5000.

I'm looking at seeing if there are some other settings gs that might require adjustment as I also can't see any of the 9000 pgms other than the ones people have wrote yet it's full of renishaw pgms that you can't see either.

[soymilk]

That’s not how it works. General practice to install the renishaw inspection plus subprograms in the root library folder. Take a picture of your directories

[gavintwopies]

Problem now fixed there was an extra parameter that need altered.

#11302 needed bit 2 (FPF) turning off as this was stopping me from going any higher up the directory as i was locking into "PATH1" only and could not come out of it to see the "LIBRARY" or "PATH2" once i had access to these i put my O9013 program into the "LIBRARY" folder along with all the other O9000 pgms and the G13 cycle code now calls up the pgm O9013 as i originally wanted.

[soymilk]

Thanks for posting your follow up