How do you mill a hexagon on lynx220lm lathe using live tooling ? Please help me

Results 1 to 20 of 20

Thread: How do you mill a hexagon on lynx220lm lathe using live tooling ? Please help me

  1. #1

    Default How do you mill a hexagon on lynx220lm lathe using live tooling ? Please help me

    Using Tapatalk


  2. #2
    Member
    Join Date
    Oct 2012
    Location
    Netherlands
    Posts
    29
    Downloads
    0
    Uploads
    0

    Default

    This is possible,
    How are you planning to program?
    ez-guide? or g-code? CAM?



  3. #3

    Default

    G code or I've got mastercam 9


    Sent from my iPhone using Tapatalk

    Using Tapatalk


  4. #4
    Member
    Join Date
    Dec 2012
    Location
    The Netherlands
    Posts
    392
    Downloads
    0
    Uploads
    0

    Default C-axis

    Hi,

    This is a G-code for a 50mm Hexagon with an axial-live tool, Fanuc 18T.
    Maybe you need other M- or G-codes.
    Look also at the Doosan attachment for c-axis milling and side drilling/tapping.
    When you use Mastercam 9 you need a proper post-processor.


    %
    O1111 ( HEXAGON - 50MM )
    ( AXIAL LIVE_TOOL )
    T0101 G98
    M86 ( C-AXIS CONTROL ON )
    G97 S3500 M3
    /M8
    G0 X90. Z10. C0
    G1 Z-5. F2000

    N1 G112 ( OR G12.1 )
    G1 G41 X50. C14.43 F500
    X50. C-14.43
    X0 C-28.86
    X-50. C-14.43
    X-50. C14.43
    X0 C28.86
    X50. C14.43

    G40 X90. F2500
    N2 G113 ( OR G13.1 )

    G1 Z2.
    G0 Z50. M5
    X250. Z200. M9
    M85 (C-AXIS CONTROL OFF )
    M30
    %

    Regards,
    Heavy_Metal.

    Attached Thumbnails Attached Thumbnails How do you mill a hexagon on lynx220lm lathe using live tooling ? Please help me-c-axis-jpg   How do you mill a hexagon on lynx220lm lathe using live tooling ? Please help me-doosan-30-series-rotary-axis-functions-pdf  


  5. #5

    Default

    Thanks ill give it a go my control is fanuc oi- tc so might have to change some codes much appreciated


    Sent from my iPhone using Tapatalk

    Using Tapatalk


  6. #6

    Default

    Does that program do it in 1 cut what about a really heavy hex, can you rough it in a canned cycle ? Regards Matt


    Sent from my iPhone using Tapatalk

    Using Tapatalk


  7. #7
    Member
    Join Date
    Dec 2012
    Location
    The Netherlands
    Posts
    392
    Downloads
    0
    Uploads
    0

    Default

    Hi Matt,

    This was a try-out on a Delrin (PCV/Plastic) round bar with a 10mm mill, one cut.
    You can program multiple passes or start with a large offset, maybe Mastercam can help with the g-code.

    Regards,
    Heavy_Metal.

    Attached Thumbnails Attached Thumbnails How do you mill a hexagon on lynx220lm lathe using live tooling ? Please help me-c-axis-2-jpg  


  8. #8

    Default

    Than you


    Sent from my iPhone using Tapatalk

    Using Tapatalk


  9. #9

    Default

    What number do to put in the T column in geometry page please and r for milling a hex


    Sent from my iPhone using Tapatalk

    Using Tapatalk


  10. #10
    Member
    Join Date
    Dec 2012
    Location
    The Netherlands
    Posts
    392
    Downloads
    0
    Uploads
    0

    Default Geometry for C-axis

    Hi Matt,

    How do you mill a hexagon on lynx220lm lathe using live tooling ? Please help me-geom-jpg

    Regards,
    Heavy_Metal.



  11. #11

    Default

    Thank you the 50 mm hex program worked a treet but I've just done a 35mm a/f and the flats look slanted could you show me a program to see what I'm doing wrong sorry to be a pain thanks matt


    Sent from my iPhone using Tapatalk

    Using Tapatalk


  12. #12
    Member
    Join Date
    Dec 2012
    Location
    The Netherlands
    Posts
    392
    Downloads
    0
    Uploads
    0

    Default

    Hi Matt,

    The next code should work.
    When you stop between line N1 and N2 you have to execute, in MDI-mode, the code G40 G113 (G13.1).
    It is not possible to make the sides 100% flat, than you have to mill with an Y-axis or a VMC-centre.
    Maybe you have to reduce the Feed-rate for a better result.

    %
    O1111 ( HEXAGON - 35MM )
    ( AXIAL LIVE_TOOL )
    T0101 G98
    M86 ( C-AXIS CONTROL ON -FANUC-18T )
    G97 S3500 M3
    /M8
    G0 G40 X75. Z10. C0
    G1 Z-5. F2000

    N1 G112 ( OR G12.1 )
    G1 G41 X35. C10.105 F500
    X35. C-10.105
    X0 C-20.21
    X-35. C-10.105
    X-35. C10.105
    X0 C20.21
    X35. C10.105
    G40 X75. F2500
    N2 G113 ( OR G13.1 )

    G1 Z2.
    G0 Z50. M5
    X250. Z200. M9
    M85 (C-AXIS CONTROL OFF )
    M30
    %

    How do you mill a hexagon on lynx220lm lathe using live tooling ? Please help me-hex-35mm-jpg



  13. #13

    Default

    I will try this tommorow , really appreciate your time thanks



    Sent from my iPhone using Tapatalk

    Using Tapatalk


  14. #14

    Default

    I wonder if a 1/2 solid carbide end mill will be better as I'm only using a standard and sticking out 41mm what's the best cutter for this type of machining is it a ripper?


    Sent from my iPhone using Tapatalk

    Using Tapatalk


  15. #15
    Member
    Join Date
    Dec 2012
    Location
    The Netherlands
    Posts
    392
    Downloads
    0
    Uploads
    0

    Default

    Hi Matt,

    Solid carbide is always better (for steel) than HSS/Co but needs stability and no vibrations.
    You can use a rough/ripper mill when the smoothness of the surface is not so important.
    I don't know what the material is for your job.
    There are a few things that matters:

    * cutting depth (radial)
    * Z-depht (axial)
    * lenght of the tool
    * Feed and Speed
    * stability toolholder and tool
    * power live-tools

    Regards,
    Heavy_Metal.



  16. #16

    Default

    Thanks I think I'll go with the solid carbide but the maximum cutter I can use is 1/2 inch as that's the biggest collet I have regards matt


    Sent from my iPhone using Tapatalk

    Using Tapatalk


  17. #17

    Default Re: How do you mill a hexagon on lynx220lm lathe using live tooling ? Please help me

    Quote Originally Posted by Heavy_Metal View Post
    Hi Matt,

    Solid carbide is always better (for steel) than HSS/Co but needs stability and no vibrations.
    You can use a rough/ripper mill when the smoothness of the surface is not so important.
    I don't know what the material is for your job.
    There are a few things that matters:

    * cutting depth (radial)
    * Z-depht (axial)
    * lenght of the tool
    * Feed and Speed
    * stability toolholder and tool
    * power live-tools

    Regards,
    Heavy_Metal.
    Hi mate is there a simple way to program a 2mm chamfer on a 29mm hole on a 75mm diameter bar on a doosan Dnm mcenter with fanuc control thanks matt


    Sent from my iPhone using Tapatalk

    Using Tapatalk


  18. #18
    Member
    Join Date
    Aug 2015
    Posts
    17
    Downloads
    0
    Uploads
    0

    Default Re: How do you mill a hexagon on lynx220lm lathe using live tooling ? Please help me

    I'm currently not seeing the results I'd like with the G12.1. Attached is the current code (Citizen L20-Mitsubishi control) and the blueprint. The print is in inches but the program is in metric. I programmed the final part dimension + the radius of the tool (.125"), this way the R value on the offset screen is 0.
    The issues are as follows, the final dimension is approximately .032" to big on the .072" +0./-.004" dimension(width across flats). I've programmed the X and C axis radially. I verified that the tool is centered (X0./Y0.) to the sub-spindle.
    Also, there's no .127mm(.005") radius on the corners of the square.




    As the program reflects I'm using G41 and G2's. Per the attached picture captured from the Instruction Manual for the Citizen L20, I should be using G42 and G3's, which is correct? I'm wondering if this is why my part has no .127mm(.005") radius on the corners of the square?


    Thanks in advance for the support.

    Attached Thumbnails Attached Thumbnails How do you mill a hexagon on lynx220lm lathe using live tooling ? Please help me-fsp-jpg   How do you mill a hexagon on lynx220lm lathe using live tooling ? Please help me-g41-g42-jpg  
    Attached Files Attached Files


  19. #19
    Registered
    Join Date
    May 2016
    Location
    United Kingdom
    Posts
    30
    Downloads
    0
    Uploads
    0

    Default Re: How do you mill a hexagon on lynx220lm lathe using live tooling ? Please help me

    I know this is probably a late answer but I am sure you will find this of use, very basic but I use it on my Lynx 220 and it works fine. you might have to play around with the speed/feeds for your material but hey ho

    O4483(SUPER MILL HEX EXT)
    (TURNING DIA = ACROSS FLATS *1.154)
    #1=50(ACCROS FLATS)
    #3=1(DEPTH OF CUT IN Z)
    #4=15(LENGTH OF FLAT Z)
    #5=0.(NULL VALUE)
    #6=8(DIAMETER OF CUTTER)


    #7=.57735(MAGIC TAN 30 DEGREES)
    #10=#1+#6(MAGIC X)
    #11=[#10*#7]/2(MAGIC C)
    #12=#10*#7(MAGIC CX)

    N1(8MM CUTTER)
    T0707M05
    M28 (C AIS ON)
    G28H0
    G0C0
    M3G97S3000
    G98
    G00X0.Z20.M8
    Z1.
    G12.1 (POLAR ON)
    G01X-#10C#11F2000 (MOVE TO START)

    N4(HERE WE GO)
    #5=#5+#3
    IF[#5GT#4]GOTO5
    Z-#5F200
    C-#11
    X0.C-#12
    C-#11X#10
    C#11
    X0C#12
    G01X-#10C#11
    GOTO4(DO IT AGAIN)

    N5(ALL DONE)
    G1Z1.F2000
    G13.1 (POLAR OFF)
    G99
    M5
    G0Z20.
    M9
    M29 (C OFF)
    G28U0.W0.
    N30M30



  20. #20
    Member DouglasR's Avatar
    Join Date
    Jul 2005
    Location
    United States
    Posts
    380
    Downloads
    0
    Uploads
    0

    Default Re: How do you mill a hexagon on lynx220lm lathe using live tooling ? Please help me

    Correct. G12.1 is used with G13.1 to cancel. If you'd like the classroom manual on this, please email me.



Posting Permissions

  • You may not post new threads
  • You may not post replies
  • You may not post attachments
  • You may not edit your posts
  •  


About CNCzone.com

    We are the largest and most active discussion forum for manufacturing industry. The site is 100% free to join and use, so join today!

Follow us on


Our Brands

How do you mill a hexagon on lynx220lm lathe using live tooling ? Please help me

How do you mill a hexagon on lynx220lm lathe using live tooling ? Please help me