PDA

View Full Version : CITIZEN E-serie (MITSUBISHI system)



subalb
01-21-2008, 08:54 AM
Hello everyone! I’ve question about programming this machine (MITSUBISHI system), what function I must use too drill through hole by cylinder. The spindle must be STOP, and movement on axis X & Z, using the angle holder. thank's for answer.

Swisstype
01-21-2008, 11:37 AM
If the spindle is stopped and you are using the #1 Turret with X and Z, it would be G711. If you use the upper, or #2 turret, it woudl be G712.

tejano4life72
01-21-2008, 03:38 PM
I use this program for the angle drill holder but its for drill on the sub side and I am only going half way thru.

G630
G632

(0.125 70DEG HOLES 0.600 DRILL PT TO COLLET )
M48C0
T2500
G50U-0.850W-2.545(tool shifts)
G98M83S4=4500
G0X0.449Z0.129T25(x start point and z start point)
/B4
#100=0
WHILE[#100LT360]DO1(i am drilling 4 times "loop")
G0X.449Z.129
C#100(changes #100 = to C axes Deg)
G1A-70.0X0.300F5.0
G0X0.449Z0.129
G1A-70.0X0.0F5.0
G0X0.449Z0.129
#100=#100+90
END1
/B4
G0X0.600T0
G50U0.850W2.545

M85
G99

tejano4life72
01-21-2008, 03:49 PM
if you want to use it for the front turret on guide bushing it would look like

$1
G610
G620
G610

$2
G610U1W1
G620

(0.125 70DEG HOLES 0.600 DRILL PT TO COLLET )
M18C0
T2500
G50U-0.850W-2.545
G98M83S4=4500
G0X0.449Z0.129T25
/B4
#100=0
WHILE[#100LT360]DO1
G0X.449Z.129
C#100(changes #100 = to C axes Deg)
G1A-70.0X0.300F5.0
G0X0.449Z0.129
G1A-70.0X0.0F5.0
G0X0.449Z0.129
#100=#100+90
END1
/B4
G0X0.600T0
G50U0.850W2.545
G0X7.05
M85
G99
G610

make sure on $1 right before you want to drill make sure you stick the Z out cause on G620 the turret is going to position for Z. Just look up G620 in win-cnc. The reason i wrote G620 its because on the citizens they use the G600 codes. If you have one that is older the G610 & G620 would be G710 and G720

tejano4life72
01-21-2008, 03:52 PM
Sorry please don't forget to que up $3 also

Swisstype
01-21-2008, 05:11 PM
Yes and no.... on E series they use G700 commands, so your G610, G620, would be G710 etc.
Secondly, if you stick the part out to do the angle work, then Superimpose G(7)620, then yes, you can do it this way, but if you are simply drilling with turret, whether it be angled or straight face, you could use G610 (G612) just as easily.

Swisstype
01-21-2008, 05:22 PM
Also, in G620,720, you need to have ths stock stuckout far enough so that you can do the work. If you do this in G710, you use Z1 in conjunction with the X axis of the turret you are using, and in this case, lets say the upper one, #2. I can't read you rprint, but lets say it is a 80 degree angle. Set your tool at 80 degrees and program away, but it would look like this:

$1
G710U1W1
G712
T2200
M5
M18C0
G50W U (uSE APPROPRIATE SHIFTS FROM pRESETTER)
G0X#814+.1Z-.1T22
M80S3=2000
Z.5
PROGRAM YOUR DRILL HERE
G0X#814+.5T0
M82
G50 CANCEL SHIFTS
G700, OR WHATEVER MODE YOU CHOOSE TO GO TO


$2
G710
G700

$3
G710
G700

subalb
01-22-2008, 04:52 AM
Thank YOU all for answer! could You tell me what's the parametr A?

tejano4life72
01-22-2008, 07:15 AM
ON $1 I WOULDN'T START OUT WITH G710U1W1, I WOULD UNDERSTAND
G710U1 TO MOVE X ALL THE WAY HOME BUT NOT W1.

cogsman1
01-22-2008, 07:44 AM
You would NOT use "W1" in $1 or the stock will go back toward your barfeed and if you have a full length bar you will move the barfeeder or the machine. Something will give!

tejano4life72
01-22-2008, 10:16 AM
what do you mean by parametr A? in my program A would be the angle you are trying to drill at. you just to draw it the part out and figure you start and end point for z. you position x and z start point then you would go A-45 X.??? if you are drilling a 45 deg angle. then just go back to your xz start point the go back in A-45. X.???. in my program i am using an endmill due to the problem that i was getting a real bad burr with a drill and i only did it in two passes to break thru the i.d.