Issues with cutter comp

[functionbikes]

I know that this has been gone over before, I am trying to figure out why my machine does not recognize my cutter comp from mastercam X , what am i doing incorrectly

[ger21]

Can you post some simple code that has the problem?

[functionbikes]

I wrote a simple program
Am I not seeing the problem

N102 G0 G17 G40 G49 G80 G90
( 1/2 FLAT ENDMILL TOOL - 1 DIA. OFF. - 41 LEN. - 1 DIA. - .5 )
N104 T1 M6
N106 G0 G90 G54 X-1.8529 Y1.4482 S3056 M3
N108 G43 H1 Z.25
N110 Z.1
N112 G1 Z-.125 F6.42
N114 Y.9482 F24.45
N116 G3 X-1.3529 Y.4482 R.5
N118 G1 X-.0842
N120 G2 X.1658 Y.1982 R.25
N122 G1 Y-1.1597
N124 G2 X-.0842 Y-1.4097 R.25
N126 G1 X-2.6216
N128 G2 X-2.8716 Y-1.1597 R.25
N130 G1 Y.1982
N132 G2 X-2.6216 Y.4482 R.25
N134 G1 X-1.3529
N136 G3 X-.8529 Y.9482 R.5
N138 G1 Y1.4482
N140 Z-.025 F6.42
N142 G0 Z.25
N144 M5
N150 M30

[ger21]

Are you talking about length comp, G43?

[functionbikes]

The length in Z is good, my issue is with side compensation

[ger21]

You need to turn it on with a G41(left) or G42(right).

[cruizer67]

THIS WOULD BE CORRECT ? RIGHT?

N102 G0 G17 G40 G49 G80 G90
( 1/2 FLAT ENDMILL TOOL - 1 DIA. OFF. - 41 LEN. - 1 DIA. - .5 )
N104 T1 M6
N106 G0 G90 G54 X-1.8529 Y1.4482 S3056 M3
N108 G43 H1 Z.25
N110 Z.1
N112 G1 G41 Z-.125 F6.42
N114 Y.9482 F24.45
N116 G3 X-1.3529 Y.4482 R.5
N118 G1 X-.0842
N120 G2 X.1658 Y.1982 R.25
N122 G1 Y-1.1597
N124 G2 X-.0842 Y-1.4097 R.25
N126 G1 X-2.6216
N128 G2 X-2.8716 Y-1.1597 R.25
N130 G1 Y.1982
N132 G2 X-2.6216 Y.4482 R.25
N134 G1 X-1.3529
N136 G3 X-.8529 Y.9482 R.5
N138 G1 Y1.4482
N140 G40 Z-.025 F6.42
N142 G0 Z.25
N144 M5
N150 M30

[beege]

Generally, Cutter comp is applied with an XY non-cutting move, and deactivated with a non-cutting XY move. If you are programming using a tool centerline path, the comp distance needs to be greater than your anticipated first and cutting move, and the approach perpendicular to your first and last cutting move. Same, really, if you are using a tool edge path, but the anticipated offset will be at least the tool radius. Turning on and off as you have it may yield undesirable movement, like tool breakage or part gouging.

[functionbikes]

I am posting out of matercamX for the tormach and have the cutter comp turning on during the ramp in move, mastercamdoes not seem to want to put the g41 in,

[beege]

There's a Mastercam option there in your toolpath that asks Comp Control/control/wear/reverse wear. Try "wear" or "control"

[functionbikes]

the wear button works it generated the g41 code in the right places- thanks for walking me thru that

[beege]

Your welcome, and thanks for the feedback!