Press Fit Help


Results 1 to 19 of 19

Thread: Press Fit Help

  1. #1
    Member
    Join Date
    Oct 2010
    Location
    USA
    Posts
    670
    Downloads
    0
    Uploads
    0

    Default Press Fit Help

    Looking to press fit some steel bushings into 6061 aluminum. The bushing is approximately .500" in diameter x .500" in depth I need this to be a secure fit and not come out. What are folks suggestions?

    My plan would be to pre-drill and then walk a contour cut in to the perfect fit.

    Thanks,

    Similar Threads:
    Awall - The Body Armor Dude
    CoolCNCStuff_ on Instagram - CoolCNCStuff.com


  2. #2
    Community Moderator Jim Dawson's Avatar
    Join Date
    Dec 2013
    Posts
    5717
    Downloads
    0
    Uploads
    0

    Default Re: Press Fit Help

    Is this a through hole? Drilling and reaming to 0.499 or 0.4985 would be my choice, maybe a bit of bearing mount LocTite for added security. You could interpolate the hole if your machine is up to the task.

    Jim Dawson
    Sandy, Oregon, USA


  3. #3
    Member
    Join Date
    Oct 2010
    Location
    USA
    Posts
    670
    Downloads
    0
    Uploads
    0

    Default Re: Press Fit Help

    Quote Originally Posted by Jim Dawson View Post
    Is this a through hole? Drilling and reaming to 0.499 or 0.4985 would be my choice, maybe a bit of bearing mount LocTite for added security. You could interpolate the hole if your machine is up to the task.
    Nope, it's not a through hole. I will already have the part set up in a fixture to run some of the other ops so I was thinking I could run it at the same time on the PCNC 1100.

    Awall - The Body Armor Dude
    CoolCNCStuff_ on Instagram - CoolCNCStuff.com


  4. #4
    Member
    Join Date
    Oct 2017
    Posts
    40
    Downloads
    0
    Uploads
    0

    Default

    Quote Originally Posted by smokediver576 View Post
    Looking to press fit some steel bushings into 6061 aluminum. The bushing is approximately .500" in diameter x .500" in depth I need this to be a secure fit and not come out. What are folks suggestions?

    My plan would be to pre-drill and then walk a contour cut in to the perfect fit.

    Thanks,
    Are you looking for suggestions on what the AL diameter should be? I have access to ANSI B.41. If you want me to take a look at the suggested diameter for your application, let me know.



  5. #5
    Community Moderator Jim Dawson's Avatar
    Join Date
    Dec 2013
    Posts
    5717
    Downloads
    0
    Uploads
    0

    Default Re: Press Fit Help

    If you know how your machine does holes you should be good to go. I do it all the time on mine, but I know exactly how it's going to cut and compensate for expected errors with appropriate offsets.

    Jim Dawson
    Sandy, Oregon, USA


  6. #6
    Gold Member
    Join Date
    Jun 2006
    Location
    Suffolk, UK
    Posts
    2512
    Downloads
    0
    Uploads
    0

    Default Re: Press Fit Help

    Quote Originally Posted by smokediver576 View Post
    Looking to press fit some steel bushings into 6061 aluminum. The bushing is approximately .500" in diameter x .500" in depth I need this to be a secure fit and not come out. What are folks suggestions?

    My plan would be to pre-drill and then walk a contour cut in to the perfect fit.

    Thanks,
    Loctite. Otherwise I think you are into reamer tolerances and bushing diameters to + or - a tenth or so. You will never contour mill the hole to the necessary accuracy.

    Phil



  7. #7
    Member
    Join Date
    Oct 2010
    Location
    USA
    Posts
    670
    Downloads
    0
    Uploads
    0

    Default Re: Press Fit Help

    Newbie thinking out loud here..... The steel bushing is .499" - wall thickness on the bushing is .062" - I'm thinking steel into soft 6061... a little retaining compound.....

    Awall - The Body Armor Dude
    CoolCNCStuff_ on Instagram - CoolCNCStuff.com


  8. #8
    Member Steve Seebold's Avatar
    Join Date
    Mar 2009
    Location
    USA and proud of it
    Posts
    1863
    Downloads
    0
    Uploads
    0

    Default Re: Press Fit Help

    In the past, I have reamed the hole .0005 undersized then put the bushings in a solution of dry ice and acetone. Then the bushings would almost fall into the hole.

    You can buy GOOD PARTS or you can buy CHEAP PARTS, but you can't buy GOOD CHEAP PARTS.


  9. #9

    Default Re: Press Fit Help

    I would bore the hole .002 under the bushing size.
    Leave the bushings in the freezer overnight, and warm up the Aluminum in the oven for a half- hour.
    They should go together easily.



  10. #10
    Gold Member
    Join Date
    Jun 2006
    Location
    Suffolk, UK
    Posts
    2512
    Downloads
    0
    Uploads
    0

    Default Re: Press Fit Help

    Quote Originally Posted by smokediver576 View Post
    Newbie thinking out loud here..... The steel bushing is .499" - wall thickness on the bushing is .062" - I'm thinking steel into soft 6061... a little retaining compound.....
    There you go. You need to press the bushing in straight or you may bell the aluminium hole. Use a vise or better still use the mill with a guide spigot in the spindle and the bushing and while the spindle is still lined up with the hole. If the bushing just drops in the loctite will do the job.

    "Walking" a profiling cut in to the correct press diameter diameter requires accurate measurement or a go no go gauge. A slightly under-size bushing would do the job of a go no go gauge. Do you have the necessary measuring equipment and/or a lathe. If the measurement/gauge is not available then profile to a slip fit and loctite.

    A profiled hole may be out of round by more than the required press fit tolerance. So again - loctite.

    Phil



  11. #11
    Member
    Join Date
    Oct 2010
    Location
    USA
    Posts
    670
    Downloads
    0
    Uploads
    0

    Default Re: Press Fit Help

    Quote Originally Posted by philbur View Post
    There you go. You need to press the bushing in straight or you may bell the aluminium hole. Use a vise or better still use the mill with a guide spigot in the spindle and the bushing and while the spindle is still lined up with the hole. If the bushing just drops in the loctite will do the job.

    "Walking" a profiling cut in to the correct press diameter diameter requires accurate measurement or a go no go gauge. A slightly under-size bushing would do the job of a go no go gauge. Do you have the necessary measuring equipment and/or a lathe. If the measurement/gauge is not available then profile to a slip fit and loctite.

    A profiled hole may be out of round by more than the required press fit tolerance. So again - loctite.

    Phil
    Hey Phil,
    Yep I've got gauge pins to do the fit checking. My plan is to turn down a bushing insert tool on the lathe, put that into a TTS holder and have the mill press the bushing in about 1/3 of the way as part of the mill op on the part. I can then finish the pressing in over on the arbor press (5 ton).

    Thanks for all the advice and help folks! I love this forum.

    Awall - The Body Armor Dude
    CoolCNCStuff_ on Instagram - CoolCNCStuff.com


  12. #12
    Member
    Join Date
    Sep 2009
    Location
    US
    Posts
    624
    Downloads
    0
    Uploads
    0

    Default Re: Press Fit Help

    Only thing I'd add is, "green Loctite". That is, 648, "press/closefit" Loctite. A new one on me, Tormach recommended it for a fix.

    The proliferation of flavors of Loctite is either brilliant marketing with no real difference, or genuinely functional. I'm inclined to some actual functionality- the green stuff seems very runny, which is what one would want for press fits. I'd expect other flavors to work fine, though.



  13. #13
    Member
    Join Date
    Jun 2012
    Location
    USA
    Posts
    311
    Downloads
    0
    Uploads
    0

    Default Re: Press Fit Help

    If you want to do it right. Look up the correct press fit value in a the Machinery's Handbook or other reference book. There are different classes of press fit and the amount of interference will vary with the diameter and materials involved. Once you determine the hole size, buy the correct reamer (they are available in .0001 increments from MSC or other suppliers).



  14. #14
    Member
    Join Date
    Feb 2006
    Location
    USA
    Posts
    7063
    Downloads
    0
    Uploads
    0

    Default Re: Press Fit Help

    Quote Originally Posted by philbur View Post
    You will never contour mill the hole to the necessary accuracy.
    I find that confusing.... Since I've done exactly that literally hundreds of times with absolutely no problems.

    Regards,
    Ray L.



  15. #15
    Member AUSTINMACHINING's Avatar
    Join Date
    Mar 2011
    Location
    usa
    Posts
    480
    Downloads
    0
    Uploads
    0

    Default Re: Press Fit Help

    Drill/bore .005 under size, ream .001 under size and press fit. If you don't have excessive back lash and a fairly tight machine, you could get away without reaming and just helical bore. Dowel pins are cheap, just test on some scrap to dial in the process.

    When reaming, half the speed and double the feed.



  16. #16
    Gold Member
    Join Date
    Jun 2006
    Location
    Suffolk, UK
    Posts
    2512
    Downloads
    0
    Uploads
    0

    Default Re: Press Fit Help

    Quote Originally Posted by SCzEngrgGroup View Post
    I find that confusing.... Since I've done exactly that literally hundreds of times with absolutely no problems.

    Regards,
    Ray L.
    Well done, but not very helpful. Procedure?

    Phil



  17. #17
    Member
    Join Date
    Feb 2006
    Location
    USA
    Posts
    7063
    Downloads
    0
    Uploads
    0

    Default Re: Press Fit Help

    Quote Originally Posted by philbur View Post
    Well done, but not very helpful. Procedure?

    Phil
    No real procedure. Do a test piece to fine-tune the final diameter, as it will be affected by temperature, the specific tool, etc, but I just interpolate the hole, with multiple finish passes, then run a bunch of parts.

    Regards,
    Ray L.



  18. #18
    Registered
    Join Date
    Jan 2015
    Posts
    1
    Downloads
    0
    Uploads
    0

    Default Re: Press Fit Help

    First you will need to be able to accurately measure the bushing diameter and the hole you are making. There is no need for more than .0005" interference fit for this bushing. If you are profile cutting the hole with your machine there is a way to get a little better roundness from the interpolation. Rough the holes out then go back and finish then with a .004" pass in both directions ( clockwise and counter-clockwise) leaving the tool size over its actual diameter by .002"and creeping up by adjusting the offset by .0002" to .0004" each time until you get to a diameter that is acceptable. It is important to drive the hole in both directions to achieve a "rounder" hole and it will help with position as well. Short of reaming or boring this will suffice for what you need to do. Hope this helps.



  19. #19
    Gold Member
    Join Date
    Jun 2006
    Location
    Suffolk, UK
    Posts
    2512
    Downloads
    0
    Uploads
    0

    Default Re: Press Fit Help

    Quote Originally Posted by SCzEngrgGroup View Post
    No real procedure. Do a test piece to fine-tune the final diameter, as it will be affected by temperature, the specific tool, etc, but I just interpolate the hole, with multiple finish passes, then run a bunch of parts.

    Regards,
    Ray L.
    How did you evaluate the impact of the blind hole out of roundness on the ability to hold the bushing in place when in use.

    Phil



Tags for this Thread

Posting Permissions

  • You may not post new threads
  • You may not post replies
  • You may not post attachments
  • You may not edit your posts
  •  


About CNCzone.com

    We are the largest and most active discussion forum for manufacturing industry. The site is 100% free to join and use, so join today!

Follow us on


Our Brands

Press Fit Help

Press Fit Help