Need Help!- I want to Post a tool list to my program.

[tmcallister74]

Does anyone know the command for adding a tool list to the top of your program?

The section I'm working on looks like this right now:


StartCode # Start of the program
%0
O[Program#]
G17 G40 G80 G90
End

1stToolChange
M01 # First tool change
G[Work]
T[Tool] M6 t[Tool] d[ToolDiam] s[Style] c[Corner] )0
G43 H[Lcomp]
Comments
M[Cool]
M[Direct] S[Speed]
G90
G0 X[H] Y[V]
Z[D]
End
............
Thanks for any info!

[Excelmachine]

I don't know how to change the post to list the tools on a posted program but the operations manager has a function for exporting a tool list, it is on the clock icon. It gives you 2 options for tooling, output tooling setup and output tooling graphics. You can try those, it will pop a window up in your web browser and than you can print those. We use them and put them in a clear folder and store them with a job box for our repeatable work. It also keeps the programs smaller and is easier to use in our opinion as you don't have to scroll thru the small screen on the controller searching for all of the tools. But, I can see some uses for your method. Good luck.

[tmcallister74]

Thanks for the help. I knew about those options I just wanted it to post in my program. I figured it out. Just took a little trial and error. Ok lots of error! lol...

[sinderal]

Please read the old post

http://www.cnczone.com/forums/surfca...o_program.html

and

http://www.cnczone.com/forums/surfca...ol_header.html

[Weld Racing]

The lines in bold need to be placed at the locations in this example, and you have to make sure you put the tool number in the comments tab as you want it to be displayed.

StartCode # Start of the program

!0
!0

%0
O[VAL1]

FILE EMPTY 1
FILE EMPTY 2

FILE ON 2 ONLY #INSERT TOOL LIST

G00 G90 G80 G40
End

1stToolChange # First tool change
T[Tool] M6

FILE ON 1
COMMENTS
FILE OFF 1

G0 G90 G[WORK] X[H] Y[V] S[Speed] M[Direct]
G00 G43 Z[D] H[Lcomp] M[Cool]
End

Infeed # Enable cutter comp
G[Side] X[H] Y[V] D[DComp] F[FRate]
end

Outfeed # Disable cutter comp
G1 G40 X[H] Y[V]
End


ToolChange # Secondary tool changes


T[Tool] M6
M01
FILE ON 1
COMMENTS
FILE OFF 1

G0 G90 G[WORK] X[H] Y[V] S[Speed] M[Direct]
G43 Z[D] H[Lcomp] M[Cool]


End

EndCode # End of the program



FILE ON MAIN ONLY

FILE INSERT 1
FILE INSERT 2


M09


G90 G00 G28 G49 Z0. M5
X0 Y9.5
M30

[pcms1965]

SURFCAM Tech Tip: SURFCAM v5.1 Setup Notes

[ADELWEIS]

read the posts and got a tool list posted at the top.Gonna save my programmer and I some time thanks guys!!!

[junky]

You can also go to your operations manager and right click on your operation and go to edit and at the bottom of the window check the box that says tool list info output to program not user, you can also type in datum locations and etc. in the white area and check the other box and it will apear in the begining of the program.