Weird circle G03 in Rhinocam Mach3 inch post


Results 1 to 6 of 6

Thread: Weird circle G03 in Rhinocam Mach3 inch post

  1. #1
    Registered
    Join Date
    Apr 2011
    Location
    USA
    Posts
    31
    Downloads
    0
    Uploads
    0

    Default Weird circle G03 in Rhinocam Mach3 inch post

    Hello,

    I searched and couldn't find anything about this. I'm using a buddy's Rhinocam to generate gcode for my machine running mach3. It's Rhinocam Pro 2.0.4.

    I have various MOPs in the single file for machining a guitar body. The simulations and everything look great in Rhinocam, but when I open the resulting Gcode in Mach3, I can see a big circle that runs through the part. I found this out after machining the part, and having it ruin the part.

    I've attached an image from mach3 showing the circle. This doesn't apear in any of the toolpaths in Rhinocam. It's during the inital horizontal roughing operation. Here is a section of the gcode, with the bolded line being the culprit:

    X2.4273Y6.0226I0.8044J-0.2479
    G01 Z1.5904
    G00 Z2.0000
    X16.1006 Y9.6531
    G01 Z1.6404 F30.0
    Z1.6154 F50.0
    G19
    G03X15.8321Y9.7421Z1.5654J-1.0577K-0.0202 F50.0
    G17
    G02X16.3582Y9.8080I0.4091J-1.1318 F70.0
    X16.7370Y9.5287I-0.1039J-0.5374
    X16.7106Y9.3160I-0.3410J-0.0657

    If I delete that line from the file, the circle disappears. Has anybody experienced this before?

    Hopefully someone knows what I need to adjust to make sure rhinocam doesn't output any weird stuff like this. I looked in the post settings, and don't really know what might need to be changed. Any help would be greatly appreciated.

    Thanks!
    Bobby

    Similar Threads:
    Attached Thumbnails Attached Thumbnails Weird circle G03 in Rhinocam Mach3 inch post-weirdarc-jpg  


  2. #2
    Member awerby's Avatar
    Join Date
    Apr 2004
    Posts
    5728
    Downloads
    0
    Uploads
    0

    Default

    Have you got "Absolute" selected in the Mach3 postprocessor configuration? If it thinks circles are relative, you can get errors like that.

    Another thing you can do is to stop letting it make arcs (G02,G03) and have it output everything as line segments. It makes the code a little longer, but you don't get hung up in the IJK stuff.

    Andrew Werby
    www.computersculpture.com



  3. #3
    Registered
    Join Date
    Apr 2011
    Location
    USA
    Posts
    31
    Downloads
    0
    Uploads
    0

    Default

    Thanks for the reply Andrew. I will check for absolute mode. With regards to lines and arcs, I always arc fit by going into the tool path and clicking the arc fitting button, then save the tool path. Now I did post a version without doing that and got the same result. Is there some where else you are referring to like a hard setting? I just want to make sure I fully understand.

    Thanks again!



  4. #4
    Registered
    Join Date
    Feb 2007
    Location
    Canada
    Posts
    505
    Downloads
    0
    Uploads
    0

    Default

    Quote Originally Posted by btsioles View Post
    Thanks for the reply Andrew. I will check for absolute mode. With regards to lines and arcs, I always arc fit by going into the tool path and clicking the arc fitting button, then save the tool path. Now I did post a version without doing that and got the same result. Is there some where else you are referring to like a hard setting? I just want to make sure I fully understand.

    Thanks again!
    Do a search for Crop Circles , sounds like it.

    http://bobcadsupport.com/techfaq/ind...=56&artlang=en

    http://www.cnczone.com/forums/792318-post28.html check the last paragraph on that post.

    Hope this help , good luck

    Last edited by Claude Boudreau; 12-29-2012 at 09:49 PM.


  5. #5
    Registered
    Join Date
    Apr 2011
    Location
    USA
    Posts
    31
    Downloads
    0
    Uploads
    0

    Default

    Quote Originally Posted by btsioles View Post
    Thanks for the reply Andrew. I will check for absolute mode. With regards to lines and arcs, I always arc fit by going into the tool path and clicking the arc fitting button, then save the tool path. Now I did post a version without doing that and got the same result. Is there some where else you are referring to like a hard setting? I just want to make sure I fully understand.

    Thanks again!
    So, looking at the post processor -> circle tab -> Arc center section, it was set to Vector from center to start. I changed it to absolute, and then reposted, and in Mach, it was yelling at me about, "radius to end of arc differs from radius to start...etc". So, I went into mach and changed the IJ setting to absolute. I restarted mach, and reloaded the file, and it loaded this time, but the silly arc is still there. I put everything back to how it was.

    I decided to look at my operation again. I'm using facing, and 40% tool width. I figured that perhaps it's getting confused transferring between paths, and so I changed it to 35% width to see what that might do, and sure enough the paths look clean in mach. No goofy arc ruining the part. I think I'll just leave it alone, and move on. I haven't had this issue before, and have machined various archtop's, so... whatever...

    Thanks for the help!!!
    -Bobby



  6. #6
    Registered
    Join Date
    Dec 2012
    Location
    Israel
    Posts
    10
    Downloads
    0
    Uploads
    0

    Default Re: Weird circle G03 in Rhinocam Mach3 inch post

    Maybe there's a line overlap in one of your curves? You will still be able to run everything fine in both CAD and CAM but you will risk the crop circles in Mach..



Tags for this Thread

Posting Permissions

  • You may not post new threads
  • You may not post replies
  • You may not post attachments
  • You may not edit your posts
  •  


About CNCzone.com

    We are the largest and most active discussion forum for manufacturing industry. The site is 100% free to join and use, so join today!

Follow us on


Our Brands

Weird circle G03 in Rhinocam Mach3 inch post

Weird circle G03 in Rhinocam Mach3 inch post