Fanuc 5T post for Mastercam x3

[Pyramid]

Hi, i need a mastercam x3 postprocessor for a Fanuc 5T, any info will help. Thanks.

[mastercamguru]

I will help you with post modifications if you need them, but you can't ask for a post here. They will close the thread before anyone can help you.

If your control is a Fanuc, you should already have a post that will work with a minimum of modifications. Mastercam already has 2 or 3 Fanuc compatible posts. The code may not look the way you are used to seeing it, but it will more than likely work just fine with a few setting changes.

For a Fanuc you should be able to use MPFAN or MPMASTER without any big changes.

What problems are you having with the MPFAN/MPMASTER post?



Powered by:

[Mike Mattera]

5T is a very different animal than what we currently understand as "Fanuc" language. I done even have an old one in my library.

Mike Mattera

[mastercamguru]

Can you post some sample code for 1 tool? We can go from there..If the mods aren't too involved, I'll come up with something for you. This is for a mill right? If we are talking about a lathe post, I may not have what it takes to help you out.

Powered by:

[NC Cams]

DUH

5M is mill

5T is lathe.

Your verson of 5T's acceptance of G code post depends if it has the G colde or enhanced G code option/parameter is set/settable in the EPROM based machine software..

I can supply a 5T programmers manual, paper copy ony, PM me for details. The hard code in your PRPOMS will determine if your machine will respond properly to the manual.

I have anohter manual that will define the parameters - you can then play with them to see if you can get your machine to respond to other parameters - some will some won't..

[mastercamguru]

DUH
5M is mill
5T is lathe.

THANKS FOR THE VOTE OF CONFIDENCE

I guessed as much since I've never come across a "T" series control

So the code must look like this:

G00X11281Z-824 
G02X7304Z0I-1989K-1989F100

Specifically noting that there are no decimal points at all.

If this is the case, it is not so big of a deal to change the format statements in a Fanuc post.

If I could have some sample code(showing tool change, and some M codes specific to this machine control) I'm sure I can modify an existing post to give this output.

Powered by:

[Pyramid]

!$$$$$$$$$$$$$$$$$$$$$$$$$
!$$ PART NO : VT/HUB GEMINI 5 -1ST END
!$$ JAW NO : 60
!$$ BUNG NO :
!$$ PRESSURE : 15
!$$ MATERIAL : 140 DIA X 93 LG K1045
!$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$
%
N001 G21
N002 G50 X376500 Z148000 S0960 M08
N003 G00 T0101 M38
N004 G96 S0140 M04
N005 G00 X150000 Z4000
N006 G01 Z900 F0017
N007 X32000
N008 G00 X144000 Z4000
N009 G71 P010 Q020 U500 W100 D3000 F0025
N010 G00 X68480
N011 G01 Z800
N012 X68500
N013 G03 X71100 Z-500 K-1300
N014 G01 Z-13200
N015 X73020
N016 Z-19000
N017 G02 X81420 Z-23200 I4200
N018 G01 X138050
N019 G03 X140650 Z-24500 K-1300
N020 G01 Z-54000
N021 G00 X376500 Z148000 M09
N022 G00 T0100 M05
N023 M01
!
!$$$$$$$$$$$$$$$ TOOL CHANGE (S. 80 DEG L/H T/F TOOL .80R )$$$$$$$$$$$$$$$$$
!
N024 G50 X383400 Z147500 S2200 M08
N025 G00 T0202 M39
N027 G97 S0800 M03
N028 G00 X0 Z8000
N029 G01 Z-47000 F0007
N030 G00 Z8000
N031 G00 X383400 Z147500 M09
N032 G00 T0200 M05
N033 M01
!
!$$$$$$$$$$$$$ TOOL CHANGE (S. 34mm "U" DRILL )$$$$$$$$$$$$$$$$$$$$$
!
N034 G50 X415700 Z148050 S0960 M08
N035 G00 T0303 M38
N036 G96 S0120 M04
N037 G00 X32500 Z4000
N038 G71 P039 Q046 U-500 W100 D1000 F0020
N039 G00 X42058
N040 G01 Z800
N940 X42056
N941 G02 X40641 Z507 K-1000
N041 G01 X38876 Z-376
N042 G02 X38290 Z-1083 K-707 I707
N043 G01 Z-17150
N044 X35600
N045 G02 X33400 Z-18250 K-1100
N046 G01 Z-40000
N047 G00 X415700 Z148050 M09
N048 G00 T0300 M05
N049 M01
!
!$$$$$$$$$$$$$ TOOL CHANGE (S. 80 DEG L/H 32mm BAR P.85 .80R )$$$$$$$$$$$$$
!
N050 G50 X417000 Z147450 S0960 M08
N051 G00 T0505 M38
N052 G96 S0180 M04
N053 G00 X42058 Z4000
N054 G01 Z400 F0010
N055 X42056
N955 G02 X41207 Z224 K-600
N956 G01 X39441 Z-659
N056 G02 X39090 Z-1083 K-424 I424
N057 G01 Z-17550
N058 X35600
N059 G02 X34200 Z-18250 K-700
N060 G01 Z-35000
N061 G01 X33500
N062 G00 Z4000
N063 G00 X417000 Z147450 M09
N064 G00 T0500 M05
N065 M01
!
!$$$$$$$$$$$$$$$ TOOL CHANGE (S. 60 DEG L/H 25mm BAR P.70 .40R )$$$$$$$$$$
!
N066 G50 X375000 Z147450 S0960 M08
N067 G00 T0606 M38
N068 G96 S0240 M04
N069 G00 X37000 Z4000
N070 G01 Z400 F0012
N071 X68500
N072 G03 X70300 Z-500 K-900
N073 G01 Z-13600
N074 X71020
N075 G03 X72220 Z-14200 K-600
N076 G01 Z-19000
N077 G02 X81420 Z-23600 I4600
N078 G01 X138050
N079 G03 X139850 Z-24500 K-900
N080 G01 Z-37000
N081 G00 X375000 Z147450 M09
N082 T0600 M05
N083 M30
%
!$$$$$$$$$$$$$$ TOOL CHANGE(S. 93 DEG L/H T/F TOOL .40R )$$$$$$$$$$$$$$

[mastercamguru]

Ok, that's what I need to get started.

It doesn't look like too big of a project for me.

I'll get on it tonight after work.

[Pyramid]

Thank you MastercamGuru.
Also, here are some more information that might help you fine tuning the post.

Fanuc 5T has canned cycles. The canned cycles are G70, G71, G72, G74, G75 and G76.

G70 = finish cycle
G71 = turning cycle
G72 = facing cycle
G74 = face grooving cycle
G75 = grooving cycle
G76 = threading cycle

I also like to draw your attention to the fact 5T does NOT use decimal point (as seen from the previous sample).
6 digits is the maximum size with the last 3 digits always stand for the decimal part.

For example:
1.2 is entered as 1200 or 01200 or 001200
0.2 is entered as 200, 0200, 00200, 000200
0.02 is entered as 20, 020, 0020, 00020, 000020 and
0.002 is entered as 2, 02, 002, 0002, 00002, 000002

Once again, I greatly appreciate your help

[mastercamguru]

Hang in there Pyramid............I only have 2 hrs a night to work on this, so it'll be awhile.

Let me know if you find a usable post, so I can help someone else.

Let me get a little closer, then I'll need some canned cycle parameters from you. eg. U, W, D......and some M code specifics eg. M38, M39

Here's what I have posting so far:

!$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$
!$$
!$$
!$$
!$$
!$$
!$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$
%
O0000
!(PROGRAM NAME - T)
!(DATE=DD-MM-YY - 08-01-09 TIME=HH:MM - 01:06)
!(MCX FILE - E:MCAMXMCXMILLLATHE TEST PART.MCX)
!(NC FILE - E:MCAMXLATHENCT.NC)
!(MATERIAL - STEEL INCH - 1030 - 200 BHN)
!(POST DEV - IN-HOUSE SOLUTIONS INC.)
!(TOOL - 1   - ROUGH FACE RIGHT - 80 DEG. - OFFSET - 1   - INSERT - NONE - HOLDER - NONE)
!(TOOL - 2   - ROUGH LEFT - 80 DEG. - OFFSET - 2   - INSERT - CNMG-432 - HOLDER - DCGNR-164D)
!(TOOL - 3   - OD FINISH LEFT - 35 DEG. - OFFSET - 3   - INSERT - VNMG-431 - HOLDER - MVJNR-164D)
G20
! $$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$
!($$$$$$$$$$$  TOOL - 1 OFFSET - 1  $$$$$$$$$$$)
!(ROUGH FACE RIGHT - 80 DEG. INSERT - NONE)
! $$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$
G28 U0 W0
G50 X100000 Y0000 Z100000
N1 T0101
G18 G99
M24
M8
G97 S375 M03
G0 X20357 Z0000
G50 S3600
G96 S200
G1 X-2268 F4321
G0 Z1000
M9
G97 S3369
G28 U0 W0
M01
! $$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$
!($$$$$$$$$$$  TOOL - 2 OFFSET - 2  $$$$$$$$$$$)
!(ROUGH LEFT - 80 DEG. INSERT - CNMG-432)
! $$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$
G28 U0 W0
G50 X100000 Y0000 Z100000
N2 T0202
G18 G99
G97 S407 M03
G0 X18790 Z0000
G50 S3600
G96 S200
G71 U1000 R0000
G71 P4 Q6 U0200 W0100 F01
N4 G0 X12962 S200
G3 X15387 Z-1213 I0000 K-1213
G1 Z-14989
G2 X16562 Z-15577 I0587 K0000
G3 X16761 Z-15593 I0000 K-0313
X18790 Z-16789 I-0198 K-1196
N6 G1 Z-38583
G97 S407
G28 U0 W0
M01
! $$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$
!($$$$$$$$$$$  TOOL - 3 OFFSET - 3  $$$$$$$$$$$)
!(OD FINISH LEFT - 35 DEG. INSERT - VNMG-431)
! $$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$$
G28 U0 W0
G50 X100000 Y0000 Z100000
N3 T0303
G18 G99
G97 S567 M03
G0 X13467 Z1522
G50 S3600
G96 S200
G1 Z0522 F01
X14575 Z0089
G3 X15387 Z-0743 I-0651 K-0832
G1 Z-14476
X17978 Z-15488
G3 X18790 Z-16320 I-0651 K-0832
G1 Z-38583
X20204 Z-37876
G28 U0 W0
M05
M30
%

Little ways to go eh. LOL

The mplmaster post is huge, and complicated, so be patient...

Powered by:

[Pyramid]

I am patient and very grateful to you. Thank you very much for your wonderful helping spirit. I am attaching a list of the G-codes. Next posting I'll attach the M-Codes listing.

[Pyramid]

This is the last part of the list of the G-Codes for the Fanuc 5T