Need HELP! OSP-E100L File size to large ??

[Biggermens]

Hello Everyone

I have a OPS-E100L Controller and just started to use Investor HSM for 3D parts
I made a pretty simple test part, generated my code with the the generic Okuma Post Processor
load it in the machine and i get a message that the file is to large Its at 717KB
I cut out all the finish passes and was still to large at 447KB
Then i generated one simple ruffing pass, file was 6KB, Controller loaded the file and seams like the machine was doing what it suppose to.

Anyone Know how to fix this or if there is a work around ??
I posted my code

Similar Threads:

• Windows x64 text file splitter that goes by lines, not file size?
• Large File Size Saved Project
• How to slice large carving on an medium size table?
• Large size laser cutting machine DC-1324
• Need Help!- large size aluminium(6061) machining

[OkumaWiz]

Without buying more memory or DNC-B you will be limited on the size of program you can run. Your management data card should show how much your machine has. It's possible to use MD0: for additional storage but don't fill it up or you may run into trouble operating the machine.

The workaround is to use the schedule program feature of the machine. It will allow you to break the program into segments and then run them by schedule program.

RUN.SDF (file name)

PSELECT A.MIN,,,Q1
PSELECT B.MIN,,,Q1
PSELECT C.MIN,,,Q1
END

Break program into sections a,b,and c and then instead of program select use sp-select to call up RUN.SDF. It will load and unload to memory allowing you to run as much as you can store.

[Biggermens]

Hi OkumaWiz

Thanks for the response, i was looking at the book and that is what i thought of doing,

What about running a rs232 cable ???
I been trying to find information on that and having a hard time to find anyting

Thanks

[Biggermens]

I just found out that Inventor HSM Has DNC software in it

Would you know were i can find information to setup up the OSP-E100L Controller to use DNC ???

[OkumaWiz]

I just found out that Inventor HSM Has DNC software in it

Would you know were i can find information to setup up the OSP-E100L Controller to use DNC ???

DNC-A is standard which allows only for file transfer. DNC-B (buffer) allows for running from host DNC software by RS232. If you have the option you will have a control panel on the side of the machine with switches most likely.

[Biggermens]

Right on, i will check that tomorrow,
Do you know if a ordernary 25 to 9 pin RS232 cable work ??

Thanks

[OkumaWiz]

It will not.

On cnc 6,8,20 jumper. 4-5 jumper then use x-on/off tx>Rx rx<tx. Gnd>gnd

At that point you only use 3 wires. Ground transmit and receive.

9600,even, 7,2 stop bits will work in most cases.

[Biggermens]

Thank you much OkumaWiz

Looks like i dont have the dnc option on this machine

I tried the sub program you sugested

File named run.sdf
In that file

Pselect a.min,,,q1
Pselect b.min,,,q1
Pselect a.min,,,q1
Pselect b.min,,,q1
End

It did not work i get a error 2222 mnemonic or local variable
Did i do somthing wrong ???

Thanks

[OkumaWiz]

Probably a typo? Did you use all CAPS for the text? That alarm implies that there is a mistype maybe in the program that it is calling up and it is thinking that it is a variable you are trying to define. For example GO instead of G0. Are you able to call the programs individually without error using the normal program select?

Best reagrds,

[deadlykitten]

hy biggermens, just like mr Wizard suggested, there seems to be a wrong syntax inside that program, perhaps with a variable ?

i would simplify the code, run only a paragraph : it works ? ok, run also the 2nd paragraph, and so on ...

thus break your code into modules, and just add one after the another, until the error appears

it is time consuming, but what else to do ?

and one more thing : sometimes, the control does not stop at the line that contains the error; please consider that N0123 has wrong content, but the control will raise an error at line N0244 for example

depends / kindly

[Biggermens]

Probably a typo? Did you use all CAPS for the text? That alarm implies that there is a mistype maybe in the program that it is calling up and it is thinking that it is a variable you are trying to define. For example GO instead of G0. Are you able to call the programs individually without error using the normal program select?

Best reagrds,

I will look over the code, try program A and program B on there own
And yes i did use all caps

Thanks

[Biggermens]

I will look over the code, try program A and program B on there own
And yes i did use all caps

Thanks

Hello

We checked program A.min and B.min and they work fine
Made sure RUN.SDF is exacly like you show, the operator said
he had to put M30 right at the end in order for RUN.SDF to run and look
we are still getting error 2222

Any ideas ??
Thanks
Biggs

[deadlykitten]

if programs perform well as individuals, then it may be possible that the control checks the amount of memory needed for both programs, when they are inside the sdf.file

if this is true, you may need a function to auto-load programs inside the control, and i have no clue how to do it, but i know that is possible, unleast on newer controls; it is on my 2do list

i am sorry, this is all i can tell now / kindly !

[deadlykitten]

This simple test should reveal how the control manages the size of all files listed inside the *.sdf : one after another as they are executed, or all togheter

please consider :
... F = file_size_limit for your cnc
... A = size_of_program_A
... B = size_of_program_B

pls be sure that A and B perform well as single individuals; also be sure that A and B have content as simple as possible ( for example only M0s )

after that, call them from the *.sdf

if ( A+B<F ) and ( error 2222 ) then pls share your files
if ( A+B<F ) and ( no error ) then :
... change size for those files, so A+B>F
... pls be sure that A and B perform well as single individuals
... if ( A+B>F ) and ( error 2222 ) then it should mean that the control takes into consideration the size of all files listed inside the *.sdf

kindly

[OkumaWiz]

Are you calling up RUN.SDF using SP-SELECT instead of PR-SELECT? Schedule programs are called up differently and do not require M30 or M2.

[Biggermens]

Are you calling up RUN.SDF using SP-SELECT instead of PR-SELECT? Schedule programs are called up differently and do not require M30 or M2.

Hi OkumaWiz

That i am not sure, i will have to ask the operator.
What should i be calling up RUN.SDF with ??

Thanks

[Biggermens]

Are you calling up RUN.SDF using SP-SELECT instead of PR-SELECT? Schedule programs are called up differently and do not require M30 or M2.

Hi OkumaWiz

That i am not sure, i will have to ask the operator.
What should i be calling up RUN.SDF with ??

Thanks

[OkumaWiz]

You will most likely need to press the extend key and look for The SCHEDULE PROGRAM SELECT key. Then you can select the SDF file.

[Biggermens]

I did exactly that and it worked
Going to do a test part next week

Thanks