Okuma MU 400V II osp-p300m-h programs

[RumenR]

I want to ask if there is another "fixing offset function" is not ( CALL OO88 (PX=___) (PY=___) (PZ=___) PC=___ PA=___ PH=___ (PP=___) )
On another machine using a subprogram (o351) which is an extension (.ssb), but once I move it on this machine have a gap axes (apparently does not want to count it). If someone can tell me why I would be grateful. (I apologize if there are errors, but write it through Google Translate)

CALL O351 PX=.... PY=..... PZ=..... PA=.... PC=..... PH=..... PP=.....

O351 
  VNCOM[1]=1
  CHK1=VSPCD[14] AND #08H (A-AXIS CHECK)
  CHK3=VSPCD[14] AND #20H (C-AXIS CHECK)
  IF[CHK1 EQ 0]NER01
  IF[CHK3 EQ 0]NER05
( ************************ )
( *** C&A AXIS PROGRAM *** )   
( ************************ )
NJP2
  IF[PA EQ EMPTY]NER02
  IF[PH EQ EMPTY]NER03
  IF[PC EQ  EMPTY]NER14
NA013
  IF[PP NE EMPTY]NA014
  PP=VACOD
NA014
  IF[PP EQ PH]NER06
  IF[PP EQ 0]NER06
  IF[PX NE EMPTY]NJP10
     PX=0
NJP10
  IF[PY NE EMPTY]NJP11
     PY=0
NJP11
  IF[PZ NE EMPTY]NJP12
     PZ=0
NJP12
NA015
 ( ***** UNIT CHECK ***** )
  BIN1=VOPRB[3] AND 66
  BIN2=VOPRB[4] AND 1
  IF[BIN1 NE 0] NB011
  IF[BIN2 EQ 0] NB012
  TANA=10000
  TANC=10000
  GOTO NA018
NB011
  TANA=1
  TANC=1
  GOTO NA018
NB012
  TANA=1000
  TANC=1000
NA018
  PC1=PC*TANC
  PA1=PA*TANA
NA019
 ( ***** OFFSET VAL ***** )
  XN=VZOFX[PH]
  YN=VZOFY[PH]
  ZN=VZOFZ[PH]
()  
  AN=VZOFA[PH]
  CN=VZOFC[PH]
()
  XL=VPVDX
  YL=VPVDY
  ZL=VPVDZ
()
 ( ***** CONVERT TO MACHINE ORIGIN ***** )
  XX=XN+PX
  YY=YN+PY
  ZZ=ZN+PZ
  AA=AN
  CC=CN
()
  XX1=XL*[1-COS[CC]]-YL*SIN[CC]*[1-COS[AA]]-ZL*SIN[AA]*SIN[CC]
  YY1=-XL*SIN[CC]+YL*COS[CC]*[1-COS[AA]]+ZL*SIN[AA]*COS[CC]
  ZZ1=-YL*SIN[AA]+ZL*[1-COS[AA]]
  XX2=XX*COS[CC]-YY*COS[AA]*SIN[CC]+ZZ*SIN[AA]*SIN[CC]
  YY2=XX*SIN[CC]+YY*COS[AA]*COS[CC]-ZZ*SIN[AA]*COS[CC]
  ZZ2=YY*SIN[AA]+ZZ*COS[AA]
    XX0=XX1+XX2
    YY0=YY1+YY2
    ZZ0=ZZ1+ZZ2
()
 ( ***** CONVERT TO NEW ORIGIN ***** )
 XX=XX0
 YY=YY0
 ZZ=ZZ0
 AA=AN+PA
 CC=CN+PC
()
  XX1=XL*[1-COS[CC]]
  YY1=XL*COS[AA]*SIN[CC]+YL*[1-COS[AA]]-ZL*SIN[AA]
  ZZ1=-XL*SIN[CC]*SIN[AA]+YL*SIN[AA]+ZL*[1-COS[AA]]
  XX2=XX*COS[CC]+YY*SIN[CC]
  YY2=-XX*COS[AA]*SIN[CC]+YY*COS[AA]*COS[CC]+ZZ*SIN[AA]
  ZZ2=XX*SIN[AA]*SIN[CC]-YY*SIN[AA]*COS[CC]+ZZ*COS[AA]
    XP=XX1+XX2
    YP=YY1+YY2
    ZP=ZZ1+ZZ2
 ( ***** ZERO OFFSET ***** )
  VZOFX[PP]=XP
  VZOFY[PP]=YP
  VZOFZ[PP]=ZP
  VZOFA[PP]=VZOFA[PH]+PA
  VZOFC[PP]=VZOFC[PH]+PC
  G15H=PP
  VNCOM[1]=0
  GOTO NRTS
 ( ***** ERROR MSG ***** )
NER01
  VUACM[1]='NO-SPEC."A"'
  VDOUT[992]=1001
  M0
NER02
  VUACM[1]='NO-DATA "A"'
  VDOUT[992]=1002
  M0
NER03
  VUACM[1]='NO-DATA "H"'
  VDOUT[992]=1003
  M0
NER04
  VUACM[1]='NO-DATA "B"'
  VDOUT[992]=1004
  M0
NER05
  VUACM[1]='NO-SPEC."B OR C"'
  VDOUT[992]=1005
  M0
NER06
  VUACM[1]='WRONG NO."P"'
  VDOUT[992]=1006
  M0
NER14
  VUACM[1]='NO-DATA "C"'
  VDOUT[992]=1007
  M0
NRTS
RTS

Similar Threads:

• OKUMA MB4000 OSP-P300M question
• Using sub programs and datum shifts, on the P300M controller
• 600V 4A Fuse a replacement for 400V 4A
• Need Help!- Upgrade an Okuma MC-4VA to allow Drip Feeding programs
• Need step up transformer 120/400V 2HP

[deadlykitten]

hy not my issue, but can pls someone explain what is this about ?

it seems to me a gauging & origins setting program, that "checks something" to do "something else "...

[Superman]

I want to ask if there is another "fixing offset function" is not ( CALL OO88 (PX=___) (PY=___) (PZ=___) PC=___ PA=___ PH=___ (PP=___) )
On another machine using a subprogram (o351) which is an extension (.ssb), but once I move it on this machine have a gap axes (apparently does not want to count it). If someone can tell me why I would be grateful. (I apologize if there are errors, but write it through Google Translate)

It has nothing to do with gauging..... it is a library file that is called up within a NC file

PDF manual attached

It is for calculating the work origin shift when the rotary axes are used .....( when using 3+2 positioning toolpath strategies.... not for when using full 5 axis paths )
- allows for not having to place the part relative to the pivot point on the machine table

It is meant to be used on MU400 / MU500 machines that have an A & C axis

What is the other machine type are you trying to use this subroutine on ?
- any alarms or messages ?

[RumenR]

I try to ride on Okuma MU 400V II (there's a 5 axes A & C), do not any alarms or messages. Just make bills but lose some 30 mm approximately, and this same subprogram (o351) use it in Okuma MU 400VA (there's a 5 axes A & C ) I guess I have to find pivot point and to change the values, but can not find it in the machine parameters.

[RumenR]

Hi, I found this parameter (Pivot Distance) and everything went normally. Thanks for your attention. Have a nice day.