Mori SL-25 Programming

[mschmitz88]

I am having troubles running this g71 code any help would be appreciated. It comes up with an alarm saying faults in finish shape 0466. This is a yasnac controll. Thanks

N10(PROFILE TOOL)
G50S1500
G0T1010M8
G96S500M3
G0G42X1.400Z.1
/G71P100Q101U.02W.002S200D500F.004R1
N100G0X.825
G01Z.02F.0015
G03X.984Z-.2R.4125F.004
G03X.825Z-.4R.4125F.004
G01X1.225Z-2.02F.004
G03X1.00Z-2.420R.550F.004
G01X1.125F.004
Z-3.1
N101G0G40X1.4Z.1
X5.Z10.
T1000
M1
G70P100Q101
G1Z.02X.825
T1000
M1

[fordav11]

The program works fine. see pic below.

You have not activated Type II G71 cycle.

Try adding a Z value on the first move line after the G71 line (i.e N100 G0 X.825 Z0.1)

You may get another error about 'not monotonous' tool movement.
That means you don't have Type II roughing cycles option.
In that case program the part using G71 without any undercuts then go back and rough the undercuts with long hand code then take your finish pass not using the G70 (i.e. just copy/paste the entire finish profile below the roughing cuts)


Or with the added Z value on N100 line you may be lucky having G71 Type II and it will just work.....

[karstexplorer]

try this

N10(PROFILE TOOL)
G50S1500
G0T1010M8
G96S500M3
G0GX1.400Z.1
G71U.05(DEPTH OF CUT)
G71P100Q101U.02W.002F.01
N100G0X.825
G01G42Z.02F.0015
G03X.984Z-.2R.4125F.004
G03X.825Z-.4R.4125F.004
G01X1.225Z-2.02F.004
G03X1.00Z-2.420R.550F.004
G01X1.125F.004 ( DON'T NEED TO KEEP ADDING FEED RATES UNLESS YOU NEED TO CHANGE IT)
Z-3.1
X1.4
N101G40
GOX5.Z10.

[fordav11]

Moving the G42 won't make any difference. The first line after G71 (N100) MUST contain a Z value or W0 in order to active type II roughing cycles.
Also its an older Yasnac control so it requires the older G71 format where all the info is on one line. The 2-line cycle format did not exist until Fanuc series-16 was released in early 90's.