CNCzone.com-The Largest Machinist Community on the net!



Home Page Mark Forums Read Today's Posts My Replies Classifieds Reviews Photo Gallery Web Links Share Files Advertise With Us Ad List
Go Back   CNCzone.com-The Largest Machinist Community on the net! > Machine Controllers Software and Solutions > Mazak, Mitsubishi, Mazatrol


Mazak, Mitsubishi, Mazatrol Discuss Mazak, Mitsubishi and Mazatrol systems here!


Reply
 
LinkBack Thread Tools Search this Thread Display Modes
  #1   Ban this user!
Old 11-06-2009, 08:24 PM
 
Join Date: Nov 2009
Location: United States
Posts: 56
tds11223 is on a distinguished road
Mastercam posts on Mazak

I am having problems getting the EIA program I created to read the Matatrol tool data page. Problems are occuring in both length and Diameter comps. The tools do not cut at same height as programmed. This could also be due to the use of both having a probe and automatic tool height measurement system both, of which, are broken. Lastly teaching the Z axis coordinate on the EIA side using G54 does not match what I get on a mazatrol work coordinate unit.

Any help would be great. Hopefully I can return the favor to someone.
Reply With Quote

  #2   Ban this user!
Old 11-07-2009, 07:48 PM
mbi mbi is offline
 
Join Date: Apr 2008
Location: usa
Posts: 33
mbi is on a distinguished road
tool length

First what control do you have?
I use Eia on our m-32. First you must decide if you are going to program from the center of the cutter or the peripheral of the cutter. I use the center of the cutter and use cutter comp.
You must set your parameters to read cutter comp. I am at home until Monday and don't have the info handy however it is in your E95 parameter I think?
Your Mazak will read your tool data page for tool length I think. Check your book to be sure. All our Mazaks use Mazatrol tool Data for tool length.
You must set all your tool offsets to 0 to control your cutter comp.
For example:
Tool # 1 is a 1.0 diameter end mill that is reground to .990. You will put your end mill into pocket #1 and go to you tool offset page and set tool offset comp #1 to -.005.
Use a D code next to your g41 or g42.
Teach your WPC’S to G54 and use g54 in your Eia code.
we also use a probe however you must use the inspection plus software to teach you g54.

I can't answer why teaching the Z axis coordinate on the EIA side using G54 does not match what I get on a mazatrol work coordinate unit. Our newer m32's to present mazaks you can run a probing unit in your mazatrol program using g54 in your additional wpc's on your wpc line.
Reply With Quote

  #3   Ban this user!
Old 11-07-2009, 10:20 PM
 
Join Date: Nov 2009
Location: United States
Posts: 56
tds11223 is on a distinguished road

The control in particular is a nexus 640. Thank you for the help on the cutter comp. for G41, that makes sense. the parameter settings were already altered and your parameter number is close to the one I had to change. I guess I was hoping that the G41 and G43 commands would match the mazatrol tool offset page in it's entirety.

For G43, I would use a H# according to the tool I want in the mazatrol tool data page?

For G41 I would enter a D# in the tool offset page(the one different than the main mazatrol tool offset page) and use the difference in the cutter diameter as the inputted value. Do I have this correct?

What, exactly, is the inspection plus software and it's capabilities? I will try to look it up online as well.

Right now both the automatic height measuring system and the probe are broken. In order to complete the part I made I needed to teach each tool off of the workpiece. Can I teach each tool of of a 3" block and back-figure a Z coordinate in order to eliminate teaching every tool off the work?

Thank you very much for your input.
Reply With Quote

  #4   Ban this user!
Old 11-07-2009, 11:31 PM
mbi mbi is offline
 
Join Date: Apr 2008
Location: usa
Posts: 33
mbi is on a distinguished road

You do not need an H with your g43. All you need is g43 and tool number. No H code. It should read the tool data page tool length. There is a parameter for this.

You are correct on the D code and g41. However check the parameter in your book so your machine knows to read the tool offset page not the tool data page for your tool offsets.

The inspection plus software is used to probe a plate in g code using macros.
Reply With Quote

  #5   Ban this user!
Old 11-08-2009, 06:09 PM
 
Join Date: Nov 2009
Location: United States
Posts: 56
tds11223 is on a distinguished road

Just to double check, the height offset line would look like

G43 T1

if using tool 1?
Reply With Quote

Sponsored Links
  #6   Ban this user!
Old 11-09-2009, 08:46 AM
 
Join Date: Mar 2005
Location: Silicon Valley, CA
Posts: 982
psychomill is on a distinguished road

No.. You do a tool call as normal then for a G43 line, you don't need to specify an H number...

T1M6
.
.
G43Z.1 (no H)


This is provided that your parameters and/or Tool Data page isn't telling the machine to look at the Offset page. If you're using the Offset page by iteself, then you need to use H as normal...

G43H1Z.1
__________________
It's just a part..... cutter still goes round and round....
Reply With Quote

  #7   Ban this user!
Old 11-09-2009, 10:30 AM
mbi mbi is offline
 
Join Date: Apr 2008
Location: usa
Posts: 33
mbi is on a distinguished road
Sample code of tool length and cutter comp

This is a sample of the g43 and mazatrol tool data.

As psychomill said G43 Z 2.0 (no H)



O2552
(/////////////////////////////////)

(Job 2554 2 plate + setup 11-09-2009)

(\\\\\\\\\\\\\\\\\\\\\\\\\\\\\\\\\)

(Plate Size 4_STEEL )
(X 35.5 )
(Y 17.875 )
(Z 3 )


(********************************)
(WPC X = -28.209 )
(WPC Y = -25.0975 )
(WPC Z = -33.567 )
(********************************)

( T97 = EM.75 C CARBIDE )
N10 G0 G40 G64 G80 G94
N12 G30 G91 Z0.
N14 G30 Y0.
N16 T97
N18 M6
N20 G0 G17 G54 G90 X-5.0145Y-9.5171 M38 S 750 M3
N22 ( T97 DIA.=0.75 NAME=EM.75 C CARBIDE )
N24 ( FINISH SIDE MILL_WIRE_SLOT_2_150_DEEP )
N26 M1
N28 M8
N30 G43 Z2.0 T97
Z-1.55
G1 Z-2.158 F150.0
G41 D97G62 X-4.8593 Y-8.9375 F10.0
Y-5.7814
G3 X-4.9343 Y-5.7064 I-0.075 J0. F7.0
G1 X-5.0343 F10.0
G3 X-5.1093 Y-5.7814 I0. J-0.075 F7.0
G1 Y-8.9375 F10.0
G40
X-4.954 Y-9.5171
X-5.0145
G41 D97G62 X-4.8593 Y-8.9375
Y-5.7814
G3 X-4.9343 Y-5.7064 I-0.075 J0. F7.0
G1 X-5.0343 F10.0
G3 X-5.1093 Y-5.7814 I0. J-0.075 F7.0
G1 Y-8.9375 F10.0
G40
X-4.954 Y-9.5171
G0 Z2.0
N72 ( PROGRAM END )
N74 M9
N76 G0 G28 G91 Z0 M5
N78 G28 G91 Y0
N80 G0 G90 G53 X-10.0
N82 G90 M30
Reply With Quote

  #8   Ban this user!
Old 11-12-2009, 07:39 AM
mbi mbi is offline
 
Join Date: Apr 2008
Location: usa
Posts: 33
mbi is on a distinguished road
Matatrol tool data page

Did you change par F93 bit 4? It should look like this 00101000. This Par enables the EIA to read the Matatrol tool data page tool length.

Just another thought? Is your post outputting code from the tool center or the peripheral? You will need it to output from the tool center. In my cam software I can program from either.
Reply With Quote

  #9   Ban this user!
Old 11-12-2009, 04:58 PM
 
Join Date: Nov 2009
Location: United States
Posts: 56
tds11223 is on a distinguished road

I changed that parameter, as well as another one that deals with tool height.

How does your software differentiate between the tool center or peripheral?
Reply With Quote

  #10   Ban this user!
Old 11-12-2009, 09:00 PM
mbi mbi is offline
 
Join Date: Apr 2008
Location: usa
Posts: 33
mbi is on a distinguished road

It is just a flag I check if I want to part line program or tool center line program.
Reply With Quote

Sponsored Links
Reply




Currently Active Users Viewing This Thread: 1 (0 members and 1 guests)
 
Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
MasterCam 5 axis Posts (not free) MrMagooo Post Processors for MC 8 11-13-2009 03:52 PM
Editing MasterCam Posts MetalMolder Post Processor Files 8 10-31-2009 01:28 AM
Mastercam X2 Posts nerfman Post Processors for MC 11 07-09-2008 09:47 PM
Mastercam Posts. How are they supposed to work? Zak@CWS Mastercam 13 05-03-2008 10:32 AM
BobCAD posts vs. Mastercam posts justCNCit BobCad-Cam 124 08-16-2006 02:17 PM




All times are GMT -5. The time now is 03:20 AM.





Powered by vBulletin® Version 3.8.7
Copyright ©2000 - 2012, vBulletin Solutions, Inc.
Content Relevant URLs by vBSEO
Template-Modifications by TMS

1 2 3 4 5 6 7 8 9 10 11 12 13 14 15 16 17 18 19 20 21 22 23 24 25 26 27 28 29 30 31 32 33 34 35 36 37 38 39 40 41 42 43 44 45 46 47 48 49 50 51 52 53 54 55 56 57 58 59 60 61 62 63 64 65 66 67 68 69 70 71 72 73 74 75 76 77 78 79 80 81 82 83 84 85 86 87 88 89 90 91 92 93 94 95 96 97 98 99 100 101 102 103 104 105 106 107 108 109 110 111 112 113 114 115 116 117 118 119 120 121 122 123 124 125 126 127 128 129 130 131 132 133 134 135 136 137 138 139 140 141 142 143 144 145 146 147 148 149 150 151 152 153 154 155 156 157 158 159 160 161 162 163 164 165 166 167 168 169 170 171 172 173 174 175 176 177 178 179 180 181 182 183 184 185 186 187 188 189 190 191 192 193 194 195 196 197 198 199 200 201 202 203 204 205 206 207 208 209 210 211 212 213 214 215 216 217 218 219 220 221 222 223 224 225 226 227 228 229 230 231 232 233 234 235 236 237 238 239 240 241 242 243 244 245 246 247 248 249 250 251 252 253 254 255 256 257 258 259 260 261 262 263 264 265 266 267 268 269 270 271 272 273 274 275 276 277 278 279 280 281 282 283 284 285 286 287 288 289 290 291 292 293 294 295 296 297 298 299 300 301 302 303 304 305 306 307 308 309 310 311 312 313 314 315 316 317 318 319 320 321 322 323 324 325 326 327 328 329 330 331 332 333 334 335 336 337 338 339 340 341 342 343 344 345 346 347 348 349 350 351 352 353 354 355 356 357 358 359 360 361