Continued post help for Prototrak DPM

[Shadowfaxx]

I believe that I spoke too soon. I still have an error in that the post is calling "M06" at the end of each NCI operation regardless of the whether there is supposed to be a tool change or not. Removing the asterisk from in front of the "t" in the program line got rid of the multile T calls but not the multiple M06 calls.

Also, is it possible to tell the post to output only linear moves, no arcs? It seems to be making very strange G2 and G3 calls.

The following is the affected code for the toolchange as it stands, I think.



psof #Start of file for non-zero tool number
pcuttype
toolchng = one
if ntools = one,
[
#skip single tool outputs, stagetool must be on
stagetool = m_one
!next_tool
]
"%", e
*progno, e
"(PROGRAM NAME - ", sprogname, ")", e
"(DATE=DD-MM-YY - ", date, " TIME=HH:MM - ", time, ")", e
pbld, n, *smetric, e
pbld, n, *sgcode, *sgplane, "G40", "G49", "G80", *sgabsinc, e
sav_absinc = absinc
if mi1 <= one, #Work coordinate system
[
absinc = one
pfbld, n, sgabsinc, *sg28ref, e
pfbld, n, *sg28ref, e
pfbld, n, "G92", *xh, *yh, *zh, e
absinc = sav_absinc
]
pcom_moveb
c_mmlt #Multiple tool subprogram call
ptoolcomment
comment
pcan
if stagetool >= zero, pbld, n, t, "M6", e
pindex
if mi1 > one, absinc = zero
pcan1, pbld, n, sgcode, sgabsinc, pwcs, pfxout, pfyout,
pfcout, *speed, *spindle, pgear, strcantext, e
pbld, n, "G43", tlngno, pfzout, scoolant, next_tool, e
absinc = sav_absinc
pcom_movea
toolchng = zero
c_msng #Single tool subprogram call

ptlchg0 #Call from NCI null tool change (tool number repeats)
pcuttype
pcom_moveb
c_mmlt #Multiple tool subprogram call
comment
pcan
pbld, n, sgplane, e
pspindchng
pbld, n, scoolant, e
if mi1 > one & workofs <> prv_workofs,
[
sav_absinc = absinc
absinc = zero
pbld, n, sgabsinc, pwcs, pfxout, pfyout, pfzout, pfcout, e
pe_inc_calc
ps_inc_calc
absinc = sav_absinc
]
if cuttype = zero, ppos_cax_lin
if gcode = one, plinout
else, prapidout
pcom_movea
c_msng #Single tool subprogram call

ptlchg #Tool change
pcuttype
toolchng = one
if mi1 = one, #Work coordinate system
[
pfbld, n, sg28ref, e
pfbld, n, "G92", *xh, *yh, *zh, e
]
pbld, n, "M01", e
pcom_moveb
c_mmlt #Multiple tool subprogram call
ptoolcomment
comment
pcan
pbld, n, t, sm06
pindex
sav_absinc = absinc
if mi1 > one, absinc = zero
pcan1, pbld, n, sgcode, sgabsinc, pwcs, pfxout, pfyout,
pfcout, speed, spindle, pgear, strcantext, e
pbld, n, "G43", tlngno, pfzout, scoolant, next_tool, e
absinc = sav_absinc
pcom_movea
toolchng = zero
c_msng #Single tool subprogram call

pretract #End of tool path, toolchange
sav_absinc = absinc
absinc = one
sav_coolant = coolant
coolant = zero
#cc_pos is reset in the toolchange here
cc_pos = zero
gcode = zero
pcan
pbld, n, sccomp, sm05, psub_end_mny, e
pcan1, pbld, n, sgabsinc, sgcode, sg28ref, scoolant, strcantext, e
pbld, n, sg28ref, protretinc, e
pcan2
absinc = sav_absinc
coolant = sav_coolant

[Rekd]

First things first:

Back up your post before you go any further.

Next, look for this:

# --------------------------------------------------------------------------
# Debugging and Factory Set Program Switches
# --------------------------------------------------------------------------
fastmode    : 1   #Posting speed optimizition
bug1        : 2     #0=No display, 1=Generic list box, 2=Editor
bug2        : 40     #Append postline labels, non-zero is column position?
bug3        : 0     #Append whatline no. to each NC line? 0
bug4        : 0     #Append NCI line no. to each NC line? 0
whatno      : yes   #Do not perform whatline branches? leave as yes

Change fastmode to "0"
Change bug1 to "2" if it isn't already
Change bug2 to "30" or "40" (this is the column to start display on)
Make sure bug3 and bug4 are as shown

Now run your post again. You'll see more information on the end of each line, similar to:

%                                       pheader
O0001                                   pheader
(107407 REV M.NCF)                      pheader
(NOV 02, 2004 07:39)                    pheader
(MC9 FILE: 107407 REV M)                pheader
(MACHINE: 3 AXIS)                       pheader
(MATERIAL: ALUMINUM INCH - 6061)        pheader
(STOCK SIZE: X 12.75 Y 3. Z 3.)         pheader
(TOOL 1: DIA 0.7100  .71 Finish EM 3FL 2.5" Clearance)  pwrtt
(TOOL 2: DIA 0.2500  1/4 CHAMFER MILL Ext To 3.0)  pwrtt
(TOOL 3: DIA 0.3160   #O DRILL 3.25 Long)  pwrtt
(TOOL 4: DIA 0.7031   45/64 DRILL)      pwrtt
(TOOL 5: DIA 0.3750  3/8-16 Cut Tap Plug H3)  pwrtt
(TOOL 6: DIA 0.7500  3/4-24 Cut Tap )   pwrtt
(TOOL 7: DIA 0.5000  1/2 CB EM 2FL SE)  pwrtt
(TOOL 8: DIA 0.2500  1/4 CB EM 2FL TICN)  pwrtt
(OVERALL MAX Z1.562)                    psof
(OVERALL MIN Z-2.6692)                  psof
N1 G00 G17 G40 G49 G80 G90 G20          psof
N2 M01                                  psof ptlchg_com
N3 ( OPERATION: 1   POCKET )            psof popnumber
N4 ( OP 1 )                             psof pcomment
N5 ( MAKE ROOM )                        psof pcomment
N6 T1 M06                               psof p__8:1109
N7(T1: .71 FINISH EM 3FL 2.5" CLEARANCE)  psof ptoolcomm
N8(MAX-DEPTH | Z-2.448)                 psof ptlchg_com
N9( TOOLPATH - POCKET)                  psof p__1:920
N10( STOCK LEFT ON X & Y = 0.)          psof p__1:920
N11( STOCK LEFT ON Z = 0.)              psof p__1:920
N12(OP ID: 1)                           psof pstock
N13 M03 S4304                           psof ptlchg_com
N14 G00 G54 X-10.7572 Y-1.6132          psof ptlchg_com
N15 G43 H1 Z1.562                       psof ptlchg_com
/ N16 M08                               psof ptlchg_com

The words you see on the right are the places in the post that those lines on
the left are called from. Now you can look at each line in the posted file,
and be able to tell where that line is coming from. Use that info to look in
your post to find the culprit for your problems.

Show an example of the posted output, as well as what you'd 'like' to have.

Also, use the "code" tags when pasting something like the NC file or the Post
stuff, it makes it easier to read, and keeps your formatting.

In the following example, you can see a null tool change between lines N108 and N117

N95 X-2.24 Y-1. F68.86                  plin plinout
N96 G03 I-.26 J0.                       pcir pcirout1
N97 G01 X-2.628 Y-.929                  plin plinout
N98(OPERATION: 6 POCKET)                ptlchg0 popnumber
N99(T1: .71 FINISH EM 3FL 2.5" CLEARANCE)  ptlchg0 ptoolcomm
N100 F34.43                             ptlchg0 plinout
N101 G41 D1 X-2.699 F68.86              plin plinout
N102 G03 X-2.77 Y-1. I0. J-.071         pcir pcirout1
N103 X-2.23 I.27 J0.                    pcir pcirout1
N104 X-2.77 I-.27 J0.                   pcir pcirout1
N105 Y-1.005 I.27 J0.                   pcir pcirout1
N106 X-2.6977 Y-1.0747 I.071 J.0013     pcir pcirout1
N107 G01 G40 X-2.6267 Y-1.0734          plin plinout
N108 G00 Z1.287                         pzrapid prapidout
N109(OPERATION: 7 CONTOUR)              ptlchg0 popnumber
N110(OP 1)                              ptlchg0 pcomment
N111(CONTOUR)                           ptlchg0 pcomment
N112(T1: .71 FINISH EM 3FL 2.5" CLEARANCE)  ptlchg0 ptoolcomm
N113( TOOLPATH - CONTOUR)               ptlchg0 p__1:920
N114( STOCK LEFT ON X & Y = 0.)         ptlchg0 p__1:920
N115( STOCK LEFT ON Z = 0.)             ptlchg0 p__1:920
N116(OP ID: 2)                          ptlchg0 pstock
N117 X-12.965 Y-3.05 Z1.                ptlchg0 prapidout
N118 Z.662                              pzrapid prapidout
N119 G01 Z.132 F34.43                   plin plinout
N120 G41 D1 X-12.915 F68.86             plin plinout
N121 G03 X-12.865 Y-3. I0. J.05         pcir pcirout1
N122 G01 Y0.                            plin plinout
N123 G03 X-12.915 Y.05 I-.05 J0.        pcir pcirout1
N124 G01 G40 X-12.965                   plin plinout
N125 G00 Z.75                           pzrapid prapidout
N126 X-12.955 Y-3.05                    prapid prapidout
N127(OPERATION: 8 CONTOUR)              ptlchg0 popnumber
N128(T1: .71 FINISH EM 3FL 2.5" CLEARANCE)  ptlchg0 ptoolcomm
N129 Z.662                              ptlchg0 prapidout
N130 G01 Z.132 F34.43                   plin plinout
N131 G41 D1 X-12.905 F68.86             plin plinout
N132 G03 X-12.855 Y-3. I0. J.05         pcir pcirout1

[Shadowfaxx]

Being able to see what part of the post generates what line really helps and I think it has identified the problem but I don't have a clue how to fix it. Apparently a null tool change is never called for.

Here is a sample of the gcode output:

T1M06                                   ptlchg
G0G90G53X0.Y0.S4500M3                   ptlchg
H1Z.1                                   ptlchg
M06                                     ptlchg
G0G90G53X-1.7042Y.0327S4500M3           ptlchg
H1Z.25                                  ptlchg
Z.1M8                                   pzrapid prapidout
G1Z-.01F10.                             plin plinout
Y.1327                                  plin plinout
G0                                      ptlchg1002 pretract
M06                                     ptlchg
G1G90G53X-1.7042Y.1327S4500M3           ptlchg
H1Z-.01                                 ptlchg
Y.2327F10.                              plin plinout
Z.09F50.                                plin plinout
G0Z.24                                  pzrapid prapidout
Z.25                                    pzrapid prapidout
M06                                     ptlchg
G0G90G53X-1.6642Y.2327S4500M3           ptlchg
H1Z.25                                  ptlchg
Z.1                                     pzrapid prapidout
G1Z-.01F10.                             plin plinout
X-1.6356                                plin plinout
G0                                      ptlchg1002 pretract
M06                                     ptlchg

What I am trying to eliminate is the multiple M06 calls. Is it possible that I have a parameter in MC set so that it is not outputting an NCI call for ptlchg0?

[Rekd]

Can you zip and attach your mastercam file with the post? I'll take a look.