4 work offsets one program

[kojack]

anyway to program part to go to the next vise in mastercam9

I just add the code @ the machine most of the time ...

Im thinking there is a setting somewherein mastecam ..


Thanks

[Cammotion]

Originally Posted by kojack anyway to program part to go to the next vise in mastercam9 I just add the code @ the machine most of the time ... Im thinking there is a setting somewherein mastecam .. Thanks

..........and go to each vise with the same tool, change tools and go to each vise and so on. I don't use MC, but some of the guys do, and I'll ask tomorrow. Someone will surely chime in with the answer though.

[Steve Arteman]

kojack,
depending on yourpost it works this way mics # 2 should 2 you will find this on the toolparameters page in v-9 then the box that says t/c planes go into there check the box that says work offset. 0= G54 1 = g55 2 =g56 etc.. again it depends on your post.
Steve
www.cad2cam.net

[cnc-king]

your other option is to create a WCS for each vise and copy your toolpath and reselect the new WCS

[manuelc149]

copy your opp. work group. in your copy change ypur tool plane in the tool param. page to your wished work offset. then combine both the work groups in the order you want.

[cadcam]

Tool path transform and in the lower right corner you will see option for different offsets.

[bradmancue]

I know in MC9 you can go into parameters in the toolpath. Where you define the tool there is an Icon that says T/C plane. In here you can change the work offset in the box stating Plane(relative to WCS) set the number to
0=G54, 1=G55, 2= G56, etc. Copy your entire prameters and paste below, change the work offset to the one needed. I am still trying to learn MC X2 so I am sure it is close to the same process if you can find out when it is embedded in the stupid MC X2 icons. I am not a big fan of MC X2 yet. I hope this helps. bradmancue

[cadcam]

Also review on thought in this help file on WCS for Version9.
this includes a 28 page on the WCS and some sample files. one of them is on programming parts with two vices and offsets.


Link for Zipped file.
http://www.mastercam-cadcam.com/wcs.zip

this is for V9 only.