CNCzone.com-The Largest Machinist Community on the net!



Home Page Mark Forums Read Today's Posts My Replies Classifieds Reviews Photo Gallery Web Links Share Files Advertise With Us Ad List
Go Back   CNCzone.com-The Largest Machinist Community on the net! > MetalWorking Machines > Haas Mills


Haas Mills Discuss Haas machinery here!


This forum is sponsored by:

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
  #1   Ban this user!
Old 12-23-2009, 12:04 PM
 
Join Date: Dec 2008
Location: usa
Posts: 312
behindpropeller is on a distinguished road
Cutter Comp Question

For everything that I have made with our TM-2 so far, I have used in computer cutter comp.

I'm curious how cutter compensation relates to tools measured with the toolsetter.

Lets say I measure a .250" endmill and it comes out at .240". I understand that the computer driven cutter comp gives me .005 of stock uncut.

So now when I program with cutter comp and the tool is measured .240 does the haas just fix that?

I'm still learning, so these questions may be trivial.

Thanks

Tim
Reply With Quote

  #2   Ban this user!
Old 12-23-2009, 01:43 PM
CNCRim's Avatar  
Join Date: Feb 2006
Location: usa
Posts: 947
CNCRim is on a distinguished road

Program 1/4" standard like brand new endmill, and if the endmill is smaller from resharp then that can be done by cutter comp in the control.
__________________
The best way to learn is trial error.
Reply With Quote

  #3   Ban this user!
Old 12-23-2009, 02:13 PM
beege's Avatar  
Join Date: Feb 2008
Location: USA
Posts: 518
beege is on a distinguished road

Comp is not going to fix your inside radii if they're not programmed, though. If you need a .125 radius and you've programmed your part to let the endmill create the radius by its size, (two intersecting lines) it won't put an arc in. You have to program an arc at the intersection so that the end mill will create the proper size radius. Just something to consider.
Reply With Quote

  #4  
Old 12-23-2009, 02:41 PM
tobyaxis's Avatar
Moderator
 
Join Date: Jan 2006
Location: USA
Posts: 4,396
tobyaxis is on a distinguished road

Originally Posted by behindpropeller View Post
For everything that I have made with our TM-2 so far, I have used in computer cutter comp.

I'm curious how cutter compensation relates to tools measured with the toolsetter.

Lets say I measure a .250" endmill and it comes out at .240". I understand that the computer driven cutter comp gives me .005 of stock uncut.

So now when I program with cutter comp and the tool is measured .240 does the haas just fix that?

I'm still learning, so these questions may be trivial.

Thanks

Tim
Depending on what your making it is known that standard endmills are .001 to .002 undersized in diameter unless you buy NC Qualified.

IMPO I use a finish endmill to Interpolate an arc rather than using a to size endmill. Doing this you can adjust the Comp for tool wear and always be sure your radii are correct.

Are you making things as a hobby or for customers??
__________________
Toby D.
"Imagination and Memory are but one thing, but for divers considerations have divers names"
Schwarzwald

(Note: The opinions expressed in this post are my own and are not necessarily those of CNCzone and its management)

www.refractotech.com
Reply With Quote

  #5   Ban this user!
Old 12-23-2009, 04:36 PM
 
Join Date: Nov 2006
Location: US
Age: 26
Posts: 181
Ydna is on a distinguished road

That definitely works best if you can menage it (without a long-extended small dia endmill). The cool thing is the Haas control will automatically adjust the feedrate for arc moves while CDC is on, to help ensure the cutter sees the same surface speed when making the arc move.

Also note (for the OP) the number you use in the CDC diameter register depends on how the part is programmed. If you program the tool's center locations (as you would without CDC) you can still use CDC with a slight modification to the program, however you'll still use a 0.0 in the CDC register.
Alternately if you program the final product's actual part locations rather than the tool center locations, then and only then will you actually put the cutter diameter in the CDC register.

It works the same both ways unless you have CDC interference problems with your locations.
Reply With Quote

Sponsored Links
  #6   Ban this user!
Old 12-24-2009, 11:21 PM
 
Join Date: Mar 2009
Location: usa
Posts: 107
crabbass is on a distinguished road

Something to consider. When I draw my parts in cad (for example a pocket with .125" radii in the corners.) If I intend to use a 1/4" endmill for finishing, (and if tolerances will permit) I will draw the corner radii larger (the bigger the better) usually just round up about .005". Then when setting up, I start the comp big (.255") and I won't get an error. I used this strategy alot when programming lathes. The .005" radius interpolation on a square shoulder when turning is dramatically smoother. It will help to reduce chatter in the corners by maintaining a smaller approach angle when entering the corner (Milling and turning).
Reply With Quote

Reply




Currently Active Users Viewing This Thread: 1 (0 members and 1 guests)
 
Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Cutter Comp Activation question bigalexe Fadal 8 09-23-2008 10:10 PM
Cutter comp on an id hole< cutter diam.?? PaintItBlue Haas Mills 5 05-05-2008 06:30 PM
Fanuc Tip code 8 cutter comp question demeyert Fanuc 10 04-04-2008 08:03 AM
SV2412 Cutter Comp Question javajesus Sharp CNC 5 02-25-2008 08:03 PM
Cutter Comp. Big"E" General Metalwork Discussion 8 03-28-2007 11:05 AM




All times are GMT -5. The time now is 08:35 PM.





Powered by vBulletin® Version 3.8.7
Copyright ©2000 - 2012, vBulletin Solutions, Inc.
Content Relevant URLs by vBSEO
Template-Modifications by TMS

1 2 3 4 5 6 7 8 9 10 11 12 13 14 15 16 17 18 19 20 21 22 23 24 25 26 27 28 29 30 31 32 33 34 35 36 37 38 39 40 41 42 43 44 45 46 47 48 49 50 51 52 53 54 55 56 57 58 59 60 61 62 63 64 65 66 67 68 69 70 71 72 73 74 75 76 77 78 79 80 81 82 83 84 85 86 87 88 89 90 91 92 93 94 95 96 97 98 99 100 101 102 103 104 105 106 107 108 109 110 111 112 113 114 115 116 117 118 119 120 121 122 123 124 125 126 127 128 129 130 131 132 133 134 135 136 137 138 139 140 141 142 143 144 145 146 147 148 149 150 151 152 153 154 155 156 157 158 159 160 161 162 163 164 165 166 167 168 169 170 171 172 173 174 175 176 177 178 179 180 181 182 183 184 185 186 187 188 189 190 191 192 193 194 195 196 197 198 199 200 201 202 203 204 205 206 207 208 209 210 211 212 213 214 215 216 217 218 219 220 221 222 223 224 225 226 227 228 229 230 231 232 233 234 235 236 237 238 239 240 241 242 243 244 245 246 247 248 249 250 251 252 253 254 255 256 257 258 259 260 261 262 263 264 265 266 267 268 269 270 271 272 273 274 275 276 277 278 279 280 281 282 283 284 285 286 287 288 289 290 291 292 293 294 295 296 297 298 299 300 301 302 303 304 305 306 307 308 309 310 311 312 313 314 315 316 317 318 319 320 321 322 323 324 325 326 327 328 329 330 331 332 333 334 335 336 337 338 339 340 341 342 343 344 345 346 347 348 349 350 351 352 353 354 355 356 357 358 359 360 361