CNCzone.com-The Largest Machinist Community on the net!



Home Page Mark Forums Read Today's Posts My Replies Classifieds Reviews Photo Gallery Web Links Share Files Advertise With Us Ad List
Go Back   CNCzone.com-The Largest Machinist Community on the net! > MetalWorking Machines > Haas Mills


Haas Mills Discuss Haas machinery here!


This forum is sponsored by:

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
  #1   Ban this user!
Old 07-07-2008, 01:04 PM
 
Join Date: Apr 2008
Location: USA
Posts: 14
X7racer is on a distinguished road
Problem with VF2 accuracy

I have a VF2 machine and recently was asked to make some parts that need exact tolerances (+- .0002). So I did some accuracy test holes with different drill bits and lines with some end mills. I found that on my X axis I am consistently off -.001 from the edge and between a series of holes will be as much as -.0007. On the Y axis it will be consistently -.0095 and between a series of holes will have -.0005 .
I used to use a mechanical click edge finder, and now use a laser edge finder, I don't believe finding the edge is a problem, and have done tests to confirm that.
I also use Mastercam X, tolerances and compensation is set to Zero.
In the VF2 control is there something I should be setting such as tool diameter or tool compensation, or is there something else not set right or not working right?
Tweet this Post!Share on Facebook
Reply With Quote

  #2  
Old 07-07-2008, 01:45 PM
HuFlungDung's Avatar
Moderator
 
Join Date: Mar 2003
Location: Canada
Posts: 4,823
HuFlungDung is on a distinguished road

Drilled holes are not accurate enough to conclude anything from testing their positions. At minimum, you should perform circular interpolation. Myself, I would perform a circular interpolation of about a 2" diameter hole in aluminum at a 20 ipm feedrate. Then set up a high accuracy indicator in the spindle and sweep the hole to see how much out of round it was.

You could run another test where you would machine a nice 'diamond' (ie., a square with its corners on the quadrant lines) and measure what size you get with a micrometer. Keep the feedrate moderate (like 20ipm) for one test, then bump it up to 100ipm and do the tests again. This should give you a feel for what the machine will do under typical conditions.
__________________
First you get good, then you get fast. Then grouchiness sets in.

(Note: The opinions expressed in this post are my own and are not necessarily those of CNCzone and its management)
Tweet this Post!Share on Facebook
Reply With Quote

  #3   Ban this user!
Old 07-07-2008, 02:31 PM
 
Join Date: Jul 2005
Location: Canada
Posts: 11,419
Geof will become famous soon enough

Originally Posted by HuFlungDung View Post
.......You could run another test where you would machine a nice 'diamond' (ie., a square with its corners on the quadrant lines) and measure what size you get with a micrometer. Keep the feedrate moderate (like 20ipm) for one test, then bump it up to 100ipm and do the tests again. This should give you a feel for what the machine will do under typical conditions.
Hu you're brilliant.

I wanted a way to check just how good (or bad) my GR510 and TM3P are and this is so simple.
__________________
An open mind is a virtue...so long as all the common sense has not leaked out.
Tweet this Post!Share on Facebook
Reply With Quote

  #4   Ban this user!
Old 07-07-2008, 04:29 PM
 
Join Date: Apr 2008
Location: USA
Posts: 14
X7racer is on a distinguished road

Hmmm. nice idea, but. maybe I am not explaining enough. The job I have requires me to drill 64 .052 and 16 .125 holes in a varing degree of pattern.
Each hole has to be within +-.0002 tolerance from the edge and from the other holes as laid out in the plans. That is why I tested it with the same size diameter bits.
I did try the circle interpolation and measured it, the difference is .0007 out of round.
Being that this machine is 7 years old and was previously used in a high production runs, I am wondering if it needs to be recalibrated or is there adjustments that can be made in the control?
Tweet this Post!Share on Facebook
Reply With Quote

  #5   Ban this user!
Old 07-07-2008, 05:23 PM
 
Join Date: Jul 2005
Location: Canada
Posts: 11,419
Geof will become famous soon enough

Have you checked it for backlash and the backlash compensation Parameters?

I don't know if it is the 'correct way' but I have checked backlash by clamping a piece of ground shafting vertically on the table; face one end and drill a hole through for a bolt.

Dial into this from the spindle and make that location the work zero.

Then just write a simple MDI program to move away a couple of inches then back to the work zero from +/-X and Y, and dial from the spindle after each move.

If there is backlash the machine will not return to the same position.
__________________
An open mind is a virtue...so long as all the common sense has not leaked out.
Tweet this Post!Share on Facebook
Reply With Quote

Sponsored Links
  #6   Ban this user!
Old 07-07-2008, 06:22 PM
 
Join Date: Jun 2006
Location: Canada
Posts: 615
big_mak is on a distinguished road

If you are trying to drill holes within 0.0002" in position, you will be wrestling with this job all the way though, and no amount of machine calibration will help you out. You will need to finsh the best possible method to put the hole in the right spot period!!!

No matter how accurate the machine is, simply drilling the holes, even drilling and reaming will not get you in the true position.

Work on gettin grepeatable results drilling holes in position, then you can tweak what ever it needs to be tweaked with regards to backlash comp and such.
__________________
"It's only funny until some one get's hurt, and then it's just hilarious!!" Mike Patton - Faith No More Ricochet
Tweet this Post!Share on Facebook
Reply With Quote

  #7  
Old 07-08-2008, 12:55 AM
HuFlungDung's Avatar
Moderator
 
Join Date: Mar 2003
Location: Canada
Posts: 4,823
HuFlungDung is on a distinguished road

I cannot honestly say I've ever had to meet those kind of specs. But if the machine was a good one, I'd think you'd have to bore the holes to finish.

If you have time to fool with trials, you could drill undersize, then find an .047 endmill and a 3mm endmill to counterbore the drilled holes, hopefully bringing them into true position. Follow this with reaming to size (and fool around trying to get a reamer that will consistently ream dead on).

If a machine has a certain degree of backlash, you still might beat the odds by using unidirectional positioning and feed only between holes. That means, all positions should be approached from the same direction so that no axis reversals occur between holes. When you do have to start the pattern over, you program a dummy point that is past the origin (if the first hole is on the origin) so that the machine must come back in the same directions for the secondary operations. This unidirectional positioning used to be some sort of an option on the old Bandit cncs

Rapid moves introduce the possibility of servo overshoot if the tuning is imperfect, and this will leave the backlash really as unknown and uncompensated correctly. So a moderate feed speed from one hole to the next one may help obtain repeatability of position.

All theory, but to hit +/-.0002", you've got to consider every trick in the book. Also, don't try to test fit the holes with gauge pins, as you need .0002" clearance to slip fit the perfect pin, so that makes conventional testing meaningless. You'd need non-contact air gauging or something to determine the size.
__________________
First you get good, then you get fast. Then grouchiness sets in.

(Note: The opinions expressed in this post are my own and are not necessarily those of CNCzone and its management)
Tweet this Post!Share on Facebook
Reply With Quote

  #8   Ban this user!
Old 07-08-2008, 09:21 PM
 
Join Date: May 2007
Location: canada
Posts: 26
pants is on a distinguished road

0.0002" tolerance is too tight. Your best chance is to first get your HFO to Relevel the machine, check geometrics, then ballbar it to get the basic compensation values and level as close as possible and then use laser calibration equipment to fill out the ballscrew compensation tables. You will need to do this in a temperature controlled enviroment, only moving in one direction at feed and pray to god your buildings got good foundations.
Im assuming you dont have linear scales on your machine?
Good luck
Tweet this Post!Share on Facebook
Reply With Quote

  #9   Ban this user!
Old 07-09-2008, 02:48 PM
 
Join Date: May 2008
Location: Canada
Posts: 63
PinnacleMachine is on a distinguished road

There's no way drilling will get that accurate. As mentioned above drill undersized then bore to finished dimension or if your plate is thin enough drill then mill the holes finished . Or drill start holes and have it wire EDM.

JP
Tweet this Post!Share on Facebook
Reply With Quote

Reply




Currently Active Users Viewing This Thread: 1 (0 members and 1 guests)
 
Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Accuracy problem GeeksGoneBad DIY-CNC Router Table Machines 11 05-31-2008 04:29 PM
fanuc 18m accuracy problem _pk_rasta_ Fanuc 8 04-11-2008 02:03 PM
K2 CNC need help with XYZ accuracy ChristopherWood Commercial CNC Wood Routers 14 12-03-2005 11:20 PM
Accuracy determination & accuracy improvement rweatherly DIY-CNC Router Table Machines 5 08-11-2005 09:37 AM
Accuracy problem with pocketing CNCadmin Yeager Automation 3 10-05-2004 12:23 AM




All times are GMT -5. The time now is 11:10 PM.





Powered by vBulletin® Version 3.8.7
Copyright ©2000 - 2012, vBulletin Solutions, Inc.
Content Relevant URLs by vBSEO
Template-Modifications by TMS

1 2 3 4 5 6 7 8 9 10 11 12 13 14 15 16 17 18 19 20 21 22 23 24 25 26 27 28 29 30 31 32 33 34 35 36 37 38 39 40 41 42 43 44 45 46 47 48 49 50 51 52 53 54 55 56 57 58 59 60 61 62 63 64 65 66 67 68 69 70 71 72 73 74 75 76 77 78 79 80 81 82 83 84 85 86 87 88 89 90 91 92 93 94 95 96 97 98 99 100 101 102 103 104 105 106 107 108 109 110 111 112 113 114 115 116 117 118 119 120 121 122 123 124 125 126 127 128 129 130 131 132 133 134 135 136 137 138 139 140 141 142 143 144 145 146 147 148 149 150 151 152 153 154 155 156 157 158 159 160 161 162 163 164 165 166 167 168 169 170 171 172 173 174 175 176 177 178 179 180 181 182 183 184 185 186 187 188 189 190 191 192 193 194 195 196 197 198 199 200 201 202 203 204 205 206 207 208 209 210 211 212 213 214 215 216 217 218 219 220 221 222 223 224 225 226 227 228 229 230 231 232 233 234 235 236 237 238 239 240 241 242 243 244 245 246 247 248 249 250 251 252 253 254 255 256 257 258 259 260 261 262 263 264 265 266 267 268 269 270 271 272 273 274 275 276 277 278 279 280 281 282 283 284 285 286 287 288 289 290 291 292 293 294 295 296 297 298 299 300 301 302 303 304 305 306 307 308 309 310 311 312 313 314 315 316 317 318 319 320 321 322 323 324 325 326 327 328 329 330 331 332 333 334 335 336 337 338 339 340 341 342 343 344 345 346 347 348 349 350 351 352 353