programming question

[kwhite2]

how could one get tool diameter offsets to load into offset page thru the program, sometimes operators forget to do this, want to control this if possible, thanks.

[chucker]

G10 L10--Programmed Tool Offest Input
G10 L10 P_X_(U_)Z_(W_)Y_(V_)R_(C_)Q_;

P offest #
X x axis offset , absolute
U x axis offset, incremental
Z z axis offest, absolute
W z axis offset, incr.
Y y axis offset, abs
V y axis offset, incr.
R tool nose rad comp amount , abs.
C tool nose rad comp amount, incr.
Q Hypothetical tool nose point

L value is optional
G11 cancels

L2 is for work offsets,
L20 is for additional work offsets (on milling machines only),
L10 is for H-geometry,
L11 is for H-wear,
L12 is for D-geometry,
L13 is for D-wear,
No L is used for lathe compensation values,
L50 is for parameter entry, and
L3 is for tool life data entry.
L1 can be used in place of L11.

[WallyL7]

Check your manual. This is right out of it...



G10 Set Offsets (Group 00)
G10 allows the programmer to set offsets within the program. Using G10
replaces the manual entry of offsets (i.e. Tool length and diameter, and work
coordinate offsets).
L – Selects offset category.
L2 Work coordinate origin for G52 and G54-G59
L10 Length offset amount (for H code)
L1 or L11 Tool wear offset amount (for H code)
L12 Diameter offset amount (for D code)
164 96-8000 Rev AK
May 2011
L13 Diameter wear offset amount (for D code)
L20 Auxiliary work coordinate origin for G110-G129
P – Selects a specific offset.
P1-P100 Used to reference D or H code offsets (L10-L13)
P0 G52 references work coordinate (L2)
P1-P6 G54-G59 references work coordinates (L2)
P1-P20 G110-G129 references auxiliary coordinates (L20)
P1-P99 G154 P1-P99 reference auxiliary coordinate (L20)
R Offset value or increment for length and diameter.
X Optional X-axis zero location.
Y Optional Y-axis zero location.
Z Optional Z-axis zero location.
A Optional A-axis zero location.
Programming Examples
G10 L2 P1 G91 X6.0 {Move coordinate G54 6.0 to the right};
G10 L20 P2 G90 X10. Y8. {Set work coordinate G111 to X10.0 ,Y8.0};
G10 L10 G90 P5 R2.5 {Set offset for Tool #5 to 2.5};
G10 L12 G90 P5 R.375 {Set diameter for Tool #5 to .375”};
G10 L20 P50 G90 X10. Y20. {Set work coordinate G154 P50 to X10. Y20.}



Looks like Chucker said the same thing while I was sidetracked with something else...

[Matt@RFR]

Or a much less confusing way:

#2001-#2200 are tool lengths
#3301-#2400 are tool length wear
#2401-#2600 are tool diameter
#2601-#2800 are tool diameter wear

So to set T10 to 3.500" length and .501" diameter either:

#2010=3.5
#2410=.5
#2610=.001

or

#2010=3.5
#2410=.501

That's less confusing to me, anyway.

You can also set your Pcool position the same way if you like: #3401-#3600.
You can also set your work offsets the same way if you're using a permanent sub plate that locates fixtures / vises the same place every time that job is run.

[kwhite2]

thanks for the help