Need Help!- Active tooling alarm 186

[alphamoose]

I'm trying to use the active tooling on a TL-25 Haas Lathe. I have written a small program in MDI mode and tried to run it. I'm able to rotate the main spindle into position, I lock it. I activate the live tooling, but when I go to MOVE the head, alarm 186 pops up telling me I'm basically trying to move the head but the main spindle is not rotating. How can I disable this alarm.

[dfrey2@rocheste]

If by active tooling you mean live tooling it sounds like your missing the M154 to turn on the c-axis.

[alphamoose]

progress!

T707
M133 P1300
M154
G99
M14
G01 G54 X0.59 F.001

Adding the M154 got rid of the 186 error, but the new error is:

390 - No spindle speed set
S code has not been encountered - Add a S code


Thanks for the help.

[dfrey2@rocheste]

your m133 p1300 need to be after the m154. & forget the m14. No need to lock the spindle for c-axis work.

[alphamoose]

Thanks for the quick response.

I tried that just now sam eissue:

I tried:
T707
M154
M14
G99
M139 P1300
G01 G54 X0.59 F0.001

I ALSO TRIED

T707
M154
M139 G54 F0.001

Same issue 390 S code

[dfrey2@rocheste]

Is that a miss print or do you really have m139 in the program. it shold be m133 or m134 depending on the spindle rotatstion that you want. M135 will stop the spindle.

[alphamoose]

Sorry miss typed it is M133

[dfrey2@rocheste]

I missed it. You have a g99 in there. you need g98 for inches per minute which would make your feed rate f1.3.

[alphamoose]

Oh I am using a right angle head a cutting a flat on the end of a shaft

So I am not moving the C at all. I am cutting Titanium so I locked the spindle to keep the shaft rigid. Does the M14 matter?

[alphamoose]

Oh G98 - I will try it now

[alphamoose]

THANK YOU SO MUCH!!

It worked - and it makes sense.

[dfrey2@rocheste]

Anytime.