CNCzone.com-The Largest Machinist Community on the net!



Home Page Mark Forums Read Today's Posts My Replies Classifieds Reviews Photo Gallery Web Links Share Files Advertise With Us Ad List
Go Back   CNCzone.com-The Largest Machinist Community on the net! > MetalWorking > General Metalwork Discussion


General Metalwork Discussion Discuss everything relating to metal work.


This forum is sponsored by:

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
  #1   Ban this user!
Old 05-14-2009, 07:46 PM
 
Join Date: Sep 2008
Location: usa
Posts: 219
RP Designs is on a distinguished road
Mirror finish on Aluminum?

So I am still waiting on my mill to arrive so I have to entertain myself by trying to pick the brains of the many experienced pro's on this site. I have tried a search and not really come up with a great answer. I have been watching youtube videos of different milling operations. I have seen many machines produce a near mirror finish on aluminum straight from the machine. Of course these where VMC's and I have no idea of what RPM they where turning. I will be running a kneemill which currently can turn the spindle at 4200rpm max. My question is what spindle speeds do I need to produce these types of finishes right off the machine, assuming the set-up, tooling and coolant is all perfect?
Reply With Quote

  #2   Ban this user!
Old 05-14-2009, 10:28 PM
Jason3's Avatar  
Join Date: Aug 2007
Location: New Zealand
Posts: 544
Jason3 is on a distinguished road
Smile

Hi there,

Were you looking for a mirror finish from face milling, or on a 3d surface? Are we talking about a CNC knee mill? You have plenty of rpm to get a good result from a face mill in alu, but that would take some time on a 3D surface.

For the best finish on Alu with a face mill I like the 45° insert type - this is the one I use: Maritool 45° face mill I also use this face mill (with different inserts) in steel, with a near mirror finish too - take a look at the video on that page, I'm getting comparable results on my (manual) knee mill. Take a light finish cut after your roughing cuts - knee mills are comparatively flexible, and you won't get a brilliant finish with a heavy cut.

If you need to mill up to a shoulder, I find this one gives nearly as good a finish: Maritool 90° face mill

In both cases you'll get the best results with the inserts designed especially for aluminium (usually very sharp, polished inserts).

You can get a nice finish with on a flat surface with a decent sharp end mill, but generally the swirl marks will mean you wouldn't consider it 'mirror' finish. On a 3D surface more RPM would greatly speed things up, but generally you'll want a very small stepover and stepdown, and your CAM software will need special 3D strategies to get the best results. I get good results with a 1/4" EM @ 25,000 - 35,000 rpm and feed rates around 100 ipm. With a 4200 rpm max, just drop the feed back proportionately and keep the coolant on - either flood or an air/mist blast. The important thing is to keep the chips out, and the cutter cool.

You can also often add a VFD to get more speed from your standard spindle motor - several others are doing this with good results, some are getting as much as 8500 rpm that way. I don't know what effect this might have on the longevity of your spindle bearings though. I use a VFD on mine, but haven't needed to turn it up past 4200 yet.

Hope that helps

Best regards,

Jason
Reply With Quote

  #3   Ban this user!
Old 05-14-2009, 11:27 PM
 
Join Date: Nov 2007
Location: USA
Posts: 59
stag53 is on a distinguished road

Getting all the way to true mirror by machining won't happen... BUT, diamond tooling will get you the closest. PCD (Poly Crystalline Diamond) will get a very shiny surface, and Mono-Crystalline will get you a little closer. High speed, high rigidity, lots of coolant needed...
Reply With Quote

  #4   Ban this user!
Old 05-15-2009, 12:12 AM
 
Join Date: Oct 2005
Location: US
Posts: 1,220
MrWild is on a distinguished road

You will never get a polished look. For that you need to buff, and mahcines that buff, don't use tooling. They use cloth and rouge.
Reply With Quote

  #5   Ban this user!
Old 05-15-2009, 06:35 AM
ImanCarrot's Avatar  
Join Date: Nov 2005
Location: UK
Posts: 1,468
ImanCarrot is on a distinguished road

To get a true optical mirror finish you'd need to diamond turn it. There's lots of companies that'll do it for you, but they aint cheap!
Attached Thumbnails
Click image for larger version

Name:	Aly01.jpg‎
Views:	239
Size:	66.3 KB
ID:	81373   Click image for larger version

Name:	Aly02.jpg‎
Views:	253
Size:	67.0 KB
ID:	81374  
__________________
I love deadlines- I like the whooshing sound they make as they fly by.
Reply With Quote

Sponsored Links
  #6   Ban this user!
Old 05-15-2009, 06:52 AM
LeeWay's Avatar  
Join Date: Jun 2004
Location: USA
Posts: 2,398
LeeWay is on a distinguished road

I started out polishing my aluminum parts before I learned how to powder coat. It worked pretty well.
Sand progressively from 150 to 600 grit. Then polish with compound. Finish up with hand rubbed Mother's.
Attached Thumbnails
Click image for larger version

Name:	bd7.jpg‎
Views:	289
Size:	14.9 KB
ID:	81375  
__________________
Lee
Reply With Quote

  #7   Ban this user!
Old 05-15-2009, 01:27 PM
 
Join Date: Sep 2008
Location: usa
Posts: 219
RP Designs is on a distinguished road

By mirror finish I mean a very shiny surface with minimal swirl marks. Mostly I would be concerned with the flats, so face milling and edge milling.
Reply With Quote

  #8   Ban this user!
Old 05-17-2009, 02:32 PM
 
Join Date: Mar 2008
Location: USA
Posts: 430
PixMan is on a distinguished road

With the top speed of your milling machine, the best benefits of using polycrystalline diamond (speed!) may not be seen. However, if you want your aluminum parts to come off the machine with the best possible finish and minimize polishing, look into a Valenite V-Flash V650 mill.

While you can't take advantage of the 2" cutter's 35,000 r.p.m. maximum speed, you can really use the fine adjustment of the inserts to get a near-mirror finish. The inserts in the cutter can be adjusted to within a micron or two, with the insert already snugged into the pocket. Use a wiper insert on it and the results on aluminum are stunning.

I've never seen insert sizes held to such tight tolerances, so having the adjustment of the inserts in the cutter is the only way to assure perfect alignment. Older designs had you snug down the insert, measure the deviation from tip-to-tip, loosen them, adjust, tighten and re-check. It would often take so long to do this that many people would just resort to using two of 6 inserts. Now with a cutter you can adjust with the inserts in tight, you'll get all 6 (more or less, depending upon the one you get) inserts cutting perfect in short order.
Reply With Quote

  #9   Ban this user!
Old 05-17-2009, 02:55 PM
mc-motorsports's Avatar  
Join Date: Feb 2007
Location: USA
Posts: 1,084
mc-motorsports is on a distinguished road

Originally Posted by ImanCarrot View Post
To get a true optical mirror finish you'd need to diamond turn it. There's lots of companies that'll do it for you, but they aint cheap!
What material is that?

You even have a perfect finish around the bolt holes where it's an interrupted cut, nice!
Reply With Quote

  #10   Ban this user!
Old 05-17-2009, 03:46 PM
 
Join Date: Jul 2005
Location: Canada
Posts: 11,565
Geof will become famous soon enough

But he only takes off half a gnat's whisker DOC with a machine that weighs in at tens of thousand of pounds I think.

But it is nice, much much betterer than I can get on my TL2.

While I am posting I guess I can make my comment to the original query: In my experience 4500 rpm is far too slow and you need to be up around 8,000 or more with cutters around 1/2" to 3/4". On side milling I have even noticed a difference between 8,000 and 10,000 with the finish being much shinier at 10,000.

But it is not just the rpm it is also the feed and machine rigidity. Look at the parts in this picture:
http://www.cnczone.com/forums/attach...4&d=1183321427

These were faced using a 5/8' corner radius two flute mill at 10,000 rpm, about .05" depth and 100 ipm. Swirl marks are visible and they are most pronounced at the locations were the cut has started or changed direction. My explanation for these is that the entire head bobs slightly when the machine shakes due to the table rapidly changing direction. The radius around the perimeter is done with a large two flute carbid router bit in one cut again at 10,000 rpm but the feed is only 50 ipm and there are no ripples visible in this. If the facing feed is dropped down to around 50 or less the swirl marks are barely visible.
__________________
An open mind is a virtue...so long as all the common sense has not leaked out.
Reply With Quote

Sponsored Links
  #11   Ban this user!
Old 05-17-2009, 04:33 PM
mc-motorsports's Avatar  
Join Date: Feb 2007
Location: USA
Posts: 1,084
mc-motorsports is on a distinguished road

I made this many years ago, 3" facemill 3000 rpm on a conventional BP. The head was perfectly square, possibly leaning .0005" towards the front, spraying WD40 inbetween the inserts to reduce dragging on the back side. It's as good as I could get with the equiptment I have.

Something with more of a mirror finish that you want to read a newspaper in the reflection requires more RPM and ridgidity. If it needs to be a mirror finish, I achieve it by polishing.

MC
Attached Thumbnails
Click image for larger version

Name:	reed racing.jpg‎
Views:	244
Size:	72.9 KB
ID:	81493  
Reply With Quote

  #12   Ban this user!
Old 05-17-2009, 06:15 PM
 
Join Date: Mar 2008
Location: USA
Posts: 430
PixMan is on a distinguished road

It's a good-looking part, but the V650 mill would get you a MUCH nicer finish by virtue of those adjustments for the inserts. A 3" one is available in course pitch (6 inserts) or fine pitch (9 inserts). Use 2 wipers in the course, or 3 wipers in the fine, adjust to within a couple of microns, and you'd easily get down to an 8 microinch (or lower) finish even at 3000 r.p.m.

The auto industry uses those cutters for that kind of finish on aluminum cylinder heads and gets finishes like that on the bi-metal surfaces across valve seats. Of course, they're running closer to the cutter's maximum speed, but the results are more a function of having all the inserts lined up perfect rather than pure speed.
Reply With Quote

Reply




Currently Active Users Viewing This Thread: 1 (0 members and 1 guests)
 
Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Mirror finish steel and aluminum parts vibratory bowl? Toggle Metal Finishing and Plating 1 01-06-2011 07:06 PM
Aluminum Finish on an X3 pzzamakr1980 General Metalwork Discussion 17 04-07-2008 01:40 AM
How do I finish Aluminum? klick0 General Metalwork Discussion 18 02-13-2008 12:36 AM
How to finish aluminum? jason_n DIY-CNC Router Table Machines 11 03-29-2007 11:04 AM
Getting a nice finish on aluminum? SRT Mike General Metalwork Discussion 19 11-19-2005 01:00 AM




All times are GMT -5. The time now is 10:14 PM.





Powered by vBulletin® Version 3.8.7
Copyright ©2000 - 2012, vBulletin Solutions, Inc.
Content Relevant URLs by vBSEO
Template-Modifications by TMS

1 2 3 4 5 6 7 8 9 10 11 12 13 14 15 16 17 18 19 20 21 22 23 24 25 26 27 28 29 30 31 32 33 34 35 36 37 38 39 40 41 42 43 44 45 46 47 48 49 50 51 52 53 54 55 56 57 58 59 60 61 62 63 64 65 66 67 68 69 70 71 72 73 74 75 76 77 78 79 80 81 82 83 84 85 86 87 88 89 90 91 92 93 94 95 96 97 98 99 100 101 102 103 104 105 106 107 108 109 110 111 112 113 114 115 116 117 118 119 120 121 122 123 124 125 126 127 128 129 130 131 132 133 134 135 136 137 138 139 140 141 142 143 144 145 146 147 148 149 150 151 152 153 154 155 156 157 158 159 160 161 162 163 164 165 166 167 168 169 170 171 172 173 174 175 176 177 178 179 180 181 182 183 184 185 186 187 188 189 190 191 192 193 194 195 196 197 198 199 200 201 202 203 204 205 206 207 208 209 210 211 212 213 214 215 216 217 218 219 220 221 222 223 224 225 226 227 228 229 230 231 232 233 234 235 236 237 238 239 240 241 242 243 244 245 246 247 248 249 250 251 252 253 254 255 256 257 258 259 260 261 262 263 264 265 266 267 268 269 270 271 272 273 274 275 276 277 278 279 280 281 282 283 284 285 286 287 288 289 290 291 292 293 294 295 296 297 298 299 300 301 302 303 304 305 306 307 308 309 310 311 312 313 314 315 316 317 318 319 320 321 322 323 324 325 326 327 328 329 330 331 332 333 334 335 336 337 338 339 340 341 342 343 344 345 346 347 348 349 350 351 352 353 354 355 356 357 358 359 360 361