CNCzone.com-The Largest Machinist Community on the net!



Home Page Mark Forums Read Today's Posts My Replies Classifieds Reviews Photo Gallery Web Links Share Files Advertise With Us Ad List
Go Back   CNCzone.com-The Largest Machinist Community on the net! > MetalWorking > General Metalwork Discussion


General Metalwork Discussion Discuss everything relating to metal work.


This forum is sponsored by:

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
  #1   Ban this user!
Old 07-14-2008, 07:52 PM
 
Join Date: Jan 2006
Location: USA
Posts: 42
orionstarman is on a distinguished road
Ball Nose EM Radius Comp

I want to rough mill a .25" radius along the X axis of my part with a .25" ball nose EM. I have calculated (sp?) my Z and Y points using .01 steps in the Y direction, but I don't know how to allow for the .125" radius of the EM. I would assume that it would be something like the "tool nose radius comp" used on the lathe. If anyone knows the formula to make this calculation please let me know.

Thanks
Tweet this Post!Share on Facebook
Reply With Quote

  #2   Ban this user!
Old 07-14-2008, 09:15 PM
 
Join Date: Jun 2006
Location: Canada
Posts: 615
big_mak is on a distinguished road

You could draw it out in CAD and pull points from it!!!!!!

It's just tangent arcs
__________________
"It's only funny until some one get's hurt, and then it's just hilarious!!" Mike Patton - Faith No More Ricochet
Tweet this Post!Share on Facebook
Reply With Quote

  #3   Ban this user!
Old 07-14-2008, 09:27 PM
 
Join Date: Jan 2006
Location: USA
Posts: 42
orionstarman is on a distinguished road

Originally Posted by big_mak View Post
You could draw it out in CAD and pull points from it!!!!!!

It's just tangent arcs
Sorry, no cad, I used the equation of a circle and a calculator to get my Z and Y points but don't I have to allow for the radius of the ball nose EM to get it to come out right.

If I just used the points that I came up with and a straight EM I would just a series of steps around the radius of the part.
Tweet this Post!Share on Facebook
Reply With Quote

  #4   Ban this user!
Old 07-15-2008, 08:24 AM
beege's Avatar  
Join Date: Feb 2008
Location: USA
Posts: 510
beege is on a distinguished road

If I understan you correctly, you want to mill a profile with the END of the ball nose end mill in the XZ plane (G18). On some controls, using G41 or G42 is an option in planes other than G17. On others, no option at all. If you program your profile using G18 and cutter comp, you'd also have to touch off your tool and take the radius amount from the tool offset, driving the center of the ball and not the tip. No help?
Tweet this Post!Share on Facebook
Reply With Quote

  #5   Ban this user!
Old 07-15-2008, 10:52 AM
 
Join Date: May 2007
Location: US
Posts: 766
Andre' B is on a distinguished road

Originally Posted by orionstarman View Post
Sorry, no cad, I used the equation of a circle and a calculator to get my Z and Y points but don't I have to allow for the radius of the ball nose EM to get it to come out right.

If I just used the points that I came up with and a straight EM I would just a series of steps around the radius of the part.
Do it just like you did but add the two radii, the one you want to cut and that of the endmill.
Then instead of programming the end of the end mill you are programming the movements of the center of the ball of the end mill. So say you wanted to put the end of the tool at Z0.0 you would program Z0.125
Tweet this Post!Share on Facebook
Reply With Quote

Sponsored Links
  #6   Ban this user!
Old 07-15-2008, 03:39 PM
 
Join Date: May 2006
Location: US
Age: 55
Posts: 124
billystein is on a distinguished road

you have to calculate the points of the center of your ball end mill and then move down z-.125 to the tip of the cutter.
Tweet this Post!Share on Facebook
Reply With Quote

  #7   Ban this user!
Old 07-25-2008, 04:11 AM
 
Join Date: Jan 2006
Location: USA
Posts: 42
orionstarman is on a distinguished road

After some work this is what I came up with. I had to picture in my head a ball with a .125" radius sitting on top of a ball with a .25" radius.

r1 = .25" =.5" DIA
r2 = .125" = .25" DIA

The point where they touch we'll call point A. This would be the same as the center of the Ball End Mill. As the .25" DIA. ball slides around (not rotates) the circumference of the .5 DIA. ball point A discribes a circle with a radius that is equal to r1 + r2. This is the circle that I needed to find the points for. Take a look at the image attached.



The Equation for a circle is X² + Y² = r²

Since I wanted to find points for Z I swapped Z² for X²
which gave me Z² + Y² = r²
In this case r² = (r1 + r2)²
which gives Z² + Y² = (r1 + r2)²
I wanted to solve for Z so I subtracted Y² from both sides which gives Z² = (r1 + r2)² +Y² Take the square root of both sides leaves Z = √((r1 + r2)² - Y²). The top of my part is Z 0 so I subtracted the difference of (r1 + r2) - √((r1 + r2)² + Y²) from 0. So the final equation comes out to be: Z = 0 - (r1 + r2) - √((r1 + r2)² + Y²) Now all I had to to was substitute in values for Y and solve for Z. I started with Y = r1 + r2 which is .375" and moved over in .01" steps till I reached 0. In the actual program though the first value I used (.375") is actually .125" from the side of my part. So in my program my first points were Z = -.375", Y = .125". It all sounds kind of confusing but it makes more sense when you look at the drawing.
Attached Thumbnails
Click image for larger version

Name:	radiuscomp005.jpg‎
Views:	92
Size:	35.3 KB
ID:	63706  
Tweet this Post!Share on Facebook
Reply With Quote

  #8   Ban this user!
Old 07-25-2008, 07:02 AM
 
Join Date: Jul 2003
Location: New Zealand
Posts: 992
Kiwi is on a distinguished road

Calculate the centre of the Ball and subtract the cutter radius off the Z as BillyStein recommended.
Y = (0.25 + 0.125) * Sin(Angle) - 0.25
Z = (0.25 + 0.125) * Cos(Angle) - (0.25 + 0.125)
Angle = 0 deg to 90deg. This will give a even cusp-height finish.
This VB program should help.
Attached Files
File Type: zip Arc Points Calculator.zip‎ (4.5 KB, 71 views)

Last edited by Kiwi; 07-25-2008 at 07:36 AM.
Tweet this Post!Share on Facebook
Reply With Quote

  #9   Ban this user!
Old 07-25-2008, 11:52 AM
bugzpulverizer's Avatar  
Join Date: Dec 2007
Location: U.S.A.
Posts: 57
bugzpulverizer is on a distinguished road

Andre'B is right. I used to use ballnose to put radii on corners, so I wouldn't have to lay part down, and do with an endmill. To get a .25 rad. you should just start at a z-.375 & x-.125, and G2 or G3 with a G18 up to Z0 X.25 R.375 or I.375. This just programs the tip of the .125 ballnosetool to make a .375 radius, which produces a .250 radius. It works on partial radius also, but you have to do a little more math to figure out the tangential endpoints. Hope that all made sense.
Tweet this Post!Share on Facebook
Reply With Quote

  #10   Ban this user!
Old 07-26-2008, 04:34 AM
 
Join Date: Jan 2007
Location: USA
Posts: 1,249
Delw is on a distinguished road

wow way too much math and work, just ask someone to do it on cad for you it would take about 3-4 mins, math was fun when I was younger but now not worth the time lol
if you dont have it yet, pm it to me( the dimensions) and I will give you g-code for it. I should be online tomorrow
Tweet this Post!Share on Facebook
Reply With Quote

Sponsored Links
  #11   Ban this user!
Old 07-27-2008, 11:10 AM
 
Join Date: Jan 2006
Location: USA
Posts: 42
orionstarman is on a distinguished road

Originally Posted by Kiwi View Post
Calculate the centre of the Ball and subtract the cutter radius off the Z as BillyStein recommended.
Y = (0.25 + 0.125) * Sin(Angle) - 0.25
Z = (0.25 + 0.125) * Cos(Angle) - (0.25 + 0.125)
Angle = 0 deg to 90deg. This will give a even cusp-height finish.
This VB program should help.
I should have remembered that one. But once I got onto the circle equation my brain was locked in.
Tweet this Post!Share on Facebook
Reply With Quote

  #12   Ban this user!
Old 07-27-2008, 11:21 AM
 
Join Date: Jan 2006
Location: USA
Posts: 42
orionstarman is on a distinguished road

Originally Posted by Delw View Post
wow way too much math and work, just ask someone to do it on cad for you it would take about 3-4 mins, math was fun when I was younger but now not worth the time lol
if you dont have it yet, pm it to me( the dimensions) and I will give you g-code for it. I should be online tomorrow
Thanks for that offer but I did get it all figured out. I was thinking about it like it was a puzzle to solve. I knew I could figure it out it just took a little time. Once I had the equation I just put it in my programmable calculator and got my point in just a few min.
Tweet this Post!Share on Facebook
Reply With Quote

Reply




Currently Active Users Viewing This Thread: 1 (0 members and 1 guests)
 
Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
tool nose radius comp joe1970 G-Code Programing 8 02-24-2010 10:43 PM
Tool nose comp for Fanuc OT? Bobesmo General Metalwork Discussion 2 12-30-2009 05:48 PM
Help with tool nose radius comp mcash3000 General CNC (Mill and Lathe) Control Software (NC) 6 05-09-2008 09:25 AM
G143 Nose Radius Comp. - Hitachi Seiki HT23J jbird68 G-Code Programing 3 08-02-2007 12:41 PM
tool nose comp.? pp-TG General Metalwork Discussion 1 09-19-2006 04:36 PM




All times are GMT -5. The time now is 10:23 AM.





Powered by vBulletin® Version 3.8.7
Copyright ©2000 - 2012, vBulletin Solutions, Inc.
Content Relevant URLs by vBSEO
Template-Modifications by TMS

1 2 3 4 5 6 7 8 9 10 11 12 13 14 15 16 17 18 19 20 21 22 23 24 25 26 27 28 29 30 31 32 33 34 35 36 37 38 39 40 41 42 43 44 45 46 47 48 49 50 51 52 53 54 55 56 57 58 59 60 61 62 63 64 65 66 67 68 69 70 71 72 73 74 75 76 77 78 79 80 81 82 83 84 85 86 87 88 89 90 91 92 93 94 95 96 97 98 99 100 101 102 103 104 105 106 107 108 109 110 111 112 113 114 115 116 117 118 119 120 121 122 123 124 125 126 127 128 129 130 131 132 133 134 135 136 137 138 139 140 141 142 143 144 145 146 147 148 149 150 151 152 153 154 155 156 157 158 159 160 161 162 163 164 165 166 167 168 169 170 171 172 173 174 175 176 177 178 179 180 181 182 183 184 185 186 187 188 189 190 191 192 193 194 195 196 197 198 199 200 201 202 203 204 205 206 207 208 209 210 211 212 213 214 215 216 217 218 219 220 221 222 223 224 225 226 227 228 229 230 231 232 233 234 235 236 237 238 239 240 241 242 243 244 245 246 247 248 249 250 251 252 253 254 255 256 257 258 259 260 261 262 263 264 265 266 267 268 269 270 271 272 273 274 275 276 277 278 279 280 281 282 283 284 285 286 287 288 289 290 291 292 293 294 295 296 297 298 299 300 301 302 303 304 305 306 307 308 309 310 311 312 313 314 315 316 317 318 319 320 321 322 323 324 325 326 327 328 329 330 331 332 333 334 335 336 337 338 339 340 341 342 343 344 345 346 347 348 349 350 351 352 353