Need Help!- tap cycle on turing center

[hackmeister]

I'm using a Puma 280L with a Fanuc 21i-TB controller, and I need to cut a 1/8-27 pipe thread in my parts. The tap goes in the part at X0, and goes to Z-.460.I was trying to use a G84 ridged tap cycle, but the book I have to use might as well be written in Korean.
If someone could please give me a program for this,and maybe please an explanation of what each of the pieces of information in the cycle is there for. Thanks very much, Hacky

[CNCRim]

http://rapidshare.com/files/33603070...ser_Manual.pdf

[dcoupar]

Try the following program (away from the part a couple of inches, please).

G00 X0 Z0.1 (POSITION TO X CENTER, Z CLEAR)
G97 S500
M29
G84 G99 Z-0.460 R0 F0.037
G00 Z2.

[hackmeister]

Thanks very much, I'll do like you say dcoupar. I'll have to check out the link later no time right now.

[hackmeister]

I got it to run. It seems the book was right after all. The lines of code you gave me were still a help dcoupar.
The program that ended up working was this.

T0404 M08
G99
G00 X0 Z.400
M29 S70
G84 Z-.590 R-.400 F.037
G80
M09
X Z go home
M01

When I first tried this program it kept giving me Alarm 200 which is an illegal S command. The book said it was parameter 5241. When I checked it , it was set to zero. So I set the parameter to 80 to see what would happen, and it worked! I'll probably go back and up that parameter to about 500 so that the rpm will be there when I need it.

dcoupar, the program you gave me made it give Alarm 205 which is, Rigid mode DI signal off. (whatever that means)
Anyways, thanks again, you really did help me out.