Need Help!- Maatsura MC-600V-DC with Yasnac MX3

[Jake E.]

We have 4 of these machines in house and trying to wrk on an interchangable system between each machine.

I have found the code for setting the G54 - G59 (J1) offsets (G10 Q2 P1-5 X# Y# Z#) but what is the code for setting offsets J2-J4?

Also how can I write the Tool Offsets in as we use a presetter from Elbo Controlli / Lyndex Nikken for setting all of our tools.

Any help would be appreciated.

Jake Enger
Setup Specialist
MaTech, Inc.
Salisbury, MD 21801
410-543-1627

[dcoupar]

Add a J2 - J5 to the G10 block:

G10 Q2 P1 X# Y# Z# (SET G54 J1)
G10 Q2 P1 J2 X# Y# Z# (SET G54 J2)
G10 Q2 P4 J2 X# Y# Z# (SET G57 J2)
G10 Q2 P6 J5 X# Y# Z# (SET G59 J5)

I would suggest you punch out the offsets to your PC to be sure of the correct format (the book shows spaces where you wouldn't expect spaces).

%
H01 X -14.2454
H02 X - 10.9335
D21 X 0.5
%

[Jake E.]

Originally Posted by dcoupar Add a J2 - J5 to the G10 block: G10 Q2 P1 X# Y# Z# (SET G54 J1) G10 Q2 P1 J2 X# Y# Z# (SET G54 J2) G10 Q2 P4 J2 X# Y# Z# (SET G57 J2) G10 Q2 P6 J5 X# Y# Z# (SET G59 J5) I would suggest you punch out the offsets to your PC to be sure of the correct format (the book shows spaces where you wouldn't expect spaces). % H01 X -14.2454 H02 X - 10.9335 D21 X 0.5 %

The work shift callouts work, but hte tool length callout just moves the z axis. is there a way to write it into the offset page?

Also when I output the offsets, I have the following:

%
H01 X 4.0780
H02 X 3.7686
H03 X 3.4360
%

[dcoupar]

Are you in the OFS function when you load the offsets?

Select EDIT mode
Press RESET
Press OFS
Press IN
Send the offset file from the PC.

Also, according to the manual you can use H or D when inputting offsets. I suppose it only punches H.

[Jake E.]

Originally Posted by dcoupar Are you in the OFS function when you load the offsets? Select EDIT mode Press RESET Press OFS Press IN Send the offset file from the PC. Also, according to the manual you can use H or D when inputting offsets. I suppose it only punches H.

I am trying to do it as a macro, similar to the workshifts. This was originally done so we can run a check program to ensure proper tool length is set so we dont have crashes. Many of our tool holders come within .020" of the fixture so we limit the length to +/-.005 to avoid collisions.

Below is an example of what we do with the Fanuc programming.


O3776(RAIL.NC)
(PALLET B)
G90G10L2P1X-13.1640Y-7.6980Z-17.6116(STAGE 1 G54)
G90G10L2P2X-22.4000Y-5.0460Z-15.8410(STAGE 2 G55)
G90G10L2P3X-19.2385Y-5.0450Z-11.1346(STAGE 3 G56)
G90G10L2P4X-14.3990Y-5.0460Z-14.1550(STAGE 4 G57)
G90G10L2P5X-13.2815Y-10.9312Z-17.5455(STAGE 5 G58)
G90G10L2P6X-15.7710Y-14.4484Z-16.3856(STAGE 6 G59)
M99




O3777(RAIL.NC)
G90
(TOOL LENGTHS)
G10L1P1R5.9210
G10L1P2R6.6841
G10L1P3R6.7853
G10L1P4R4.0670
G10L1P5R7.3700
G10L1P6R5.3505
G10L1P7R5.2850
M99


O8775(RAIL.NC)
(TOOL LENGTH COMPARISON MACRO PROGRAM)
IF[ABS[#2001-5.9207]GT.005]GOTO1001
IF[ABS[#2002-6.6834]GT.005]GOTO1002
IF[ABS[#2003-6.7855]GT.005]GOTO1003
IF[ABS[#2004-4.0670]GT.005]GOTO1004
IF[ABS[#2005-7.3746]GT.005]GOTO1005
IF[ABS[#2006-5.3490]GT.005]GOTO1006
IF[ABS[#2007-5.2878]GT.005]GOTO1007

GOTO9999

N1001#3000=101(H1 OUT OF RANGE)
N1002#3000=102(H2 OUT OF RANGE)
N1003#3000=103(H3 OUT OF RANGE)
N1004#3000=104(H4 OUT OF RANGE)
N1005#3000=105(H5 OUT OF RANGE)
N1006#3000=106(H6 OUT OF RANGE)
N1007#3000=107(H7 OUT OF RANGE)
N9999

M99





O8777(RAIL.NC)
(INSP PROG FOR PALLET B)

(WORK SHIFTS X)
IF[ABS[#5221+13.1640]GT.010]GOTO1001(X G54)
IF[ABS[#5241+22.4000]GT.010]GOTO1002(X G55)
IF[ABS[#5261+19.2370]GT.010]GOTO1003(X G56)
IF[ABS[#5281+14.4010]GT.010]GOTO1004(X G57)
IF[ABS[#5301+13.2840]GT.010]GOTO1005(X G58)
IF[ABS[#5321+15.7710]GT.010]GOTO1006(X G59)


(WORK SHIFTS Y)
IF[ABS[#5222+7.6980]GT0.01]GOTO1007(Y G54)
IF[ABS[#5242+5.0460]GT0.01]GOTO1008(Y G55)
IF[ABS[#5262+5.0450]GT0.01]GOTO1009(Y G56)
IF[ABS[#5282+5.0468]GT0.01]GOTO1010(Y G57)
IF[ABS[#5302+10.9340]GT0.01]GOTO1011(Y G58)
IF[ABS[#5322+14.4460]GT0.01]GOTO1012(Y G59)


(WORK SHIFTS Z)
IF[ABS[#5223+17.6116]GT0.01]GOTO1013(Z G54)
IF[ABS[#5243+15.8410]GT.010]GOTO1014(Z G55)
IF[ABS[#5263+11.1326]GT0.01]GOTO1015(Z G56)
IF[ABS[#5283+14.1550]GT.010]GOTO1016(Z G57)
IF[ABS[#5303+17.5451]GT0.01]GOTO1017(Z G58)
IF[ABS[#5323+16.3856]GT.010]GOTO1018(Z G59)
GOTO9999

(PALLET OUT OF RANGE X)
N1001#3000=120(X G54 OUT OF RANGE)
N1002#3000=120(X G55 OUT OF RANGE)
N1003#3000=120(X G56 OUT OF RANGE)
N1004#3000=120(X G57 OUT OF RANGE)
N1005#3000=120(X G58 OUT OF RANGE)
N1006#3000=120(X G59 OUT OF RANGE)


( OUT OF RANGE Y)
N1007#3000=120(Y G54 OUT OF RANGE)
N1008#3000=120(Y G55 OUT OF RANGE)
N1009#3000=120(Y G56 OUT OF RANGE)
N1010#3000=120(Y G57 OUT OF RANGE)
N1011#3000=120(Y G58 OUT OF RANGE)
N1012#3000=120(Y G59 OUT OF RANGE)

( OUT OF RANGE Z)
N1013#3000=120(Z G54 OUT OF RANGE)
N1014#3000=120(Z G55 OUT OF RANGE)
N1015#3000=120(Z G56 OUT OF RANGE)
N1016#3000=120(Z G57 OUT OF RANGE)
N1017#3000=120(Z G58 OUT OF RANGE)
N1018#3000=120(Z G59 OUT OF RANGE)

N9999

M99

[dcoupar]

G90 G10 P# R#

Sets offset #P (1-99) to value R

[Jake E.]

Originally Posted by dcoupar G90 G10 P# R# Sets offset #P (1-99) to value R

Thanks, will try that tomorrow.

[Jake E.]

OK
The different gcodes are working so we will be able to write the offsets in from the program for both the tools and the workshifts. Thanks very much for your help dcoupar.

Next problem is trying to figure out the GOTO command ( keep gettting an error when using GOTO, looking for an address) and the parameters for the tool lengths to use for our inspection macros (see previous post).

[stevo1]

Originally Posted by Jake E. Next problem is trying to figure out the GOTO command ( keep gettting an error when using GOTO, looking for an address) and the parameters for the tool lengths to use for our inspection macros (see previous post).

What alarm are you getting and at what specifc GOTO statment is it alarming out at?

Stevo

[Jake E.]

Anytime I write a GOTO command, when I enter it the control seperates the G from GOTO and an alarm comes up as stating "invalid address".

[dcoupar]

Isn't there an alarm number?

[Jake E.]

yeah, I will get it in a few, working on a fixture program at the moment for a Makino