reneshaw probing program for brother tc-s2c

[PCCDon]

I have a brother tc-S2C I just got and I need to do reneshaw probing a bit different than the manufacturing intended. I need to probe for locations and input a desired axis location into a variable such as #800-#899
then load this into position to be called out by a G92 with a variable position. Basically I have a fixed G54 and G55 that cannot move because of the amount of parts and the fact I run 2 different part numbers at the same time on the same machine .I have extreme variabiltiy in my parts which is leading me to probing so I want to probe for a G92 from a G54 location beacuse the feature I'm cutting is a moving target. But at the same time I want a variable probing program that will load its positions
from the main operation program into the variable then switch to a sub program that is my probing routine but is basically completely variable driven sytem except for the cutting.

here is an eaxple of what I want to do would love it if some one could help out

Touch -> X zero in program <- Touch
(X probe point 2) (X zero & cl of feature) (X probe point 1)
record into #801 #803 record into #800


Here is example of probing sub program I have in mind but I need to know how to program the actual touch program to come over touch a point and record the axis of movement into a variable

01000(probe for CL of X)

I'm missing this part I don't know how to write a probe touch sequence

(#801) - (#800) = (#802)
(#802) / 2 = (#803)

G99

[JMS4287]

What Renishaw Software Are you usuing...they Have Macro's written already to do exactly what you're trying to do.....

Here's a Quick example of probe setting a Z work shift off the face of a part in a Lathe...Same concept different machine different axis...

%
O3330(SET-Z-ZERO)

G0G20G40G97G98

#2601=[#534*[-1]]
(SHIFT-ZERO)
#2601=#2601+#526

T0101
Y0.

IF[#1001EQ1]GOTO7000

G0X#532Z[1.0+#526]

G65P9314X#532Z.2F50.

G65P9513Z0.T1014

G65P9314Z[1.0+#526]F200.

#824=#2114

#2601=#2601+#824

#2114=0

G0T0
G28W0.

M99

N7000
#3000=1(PROBE NOT ON)


M99


Prg's 9313 and 9314 are Renishaw Macro's.... in this case Renishaw is storing the Position in an wear offset, I picked offset 14...I'm them taking that offset #2114...writing it to #824...and adding that to my z workshift(#2601)

I could have skipped writing it #824...It's only there so I can see it If I want to...Or pick it up later for something else...

Picking up an X location is basically the same concept...just call a differant Renishaw Sub Program...If you have the Probe you should have the software....