Fanuc 18 imb measuring the workpiece with macro

[Osmanselim]

Hi,

I am used awea with Fanuc 18 imb kontrol. We need workpiece zero set prg with macro prg is it possible

like this mitsubishi we need fanuc

#100=54 (Cordinate set G54)
#101=[#100-54]x20
#105=5221+#101
#111=5021
M0 (Please push the cycle start button and goto other corner and touch)
#112=#5021
#113=[#14+112]/2
#5221=#113
m30


#111=#5022
M0
#112=#5022
#113=[#111+#112]/2
#5022=#113
M30

For Z Axis
#[2000+#120]=[#5023+#121]
m30


Thanks

[Osmanselim]

no bady no know?

[gar]

071019-0600 EST USA

Osmanselim:

Does your last message mean that you are in desparate need of an answer?

I am not familar with Mitsubishi, and could only guess on Fanuc based on my experience with HAAS.

Sorry no one with experience on your machines has responded.

.

[dpuch]

The macro you listed looks like it all might match up with a fanuc control, except the #101=[#100-54]x20 should be #101=[#100-54]*20

I did not verify the variables used, but they do look right. #5221, 5222 and 5223 are G54 X, Y, Z The #5021-5023 seem like they might be typos for 5221-5223.

The logic does not make much sense, are these snipits of code form different programs? I see #14 in there as well, is there a program or line with paramaters that calls these?

Dale

[slavetothemetal]

Osmanselim,

I have a few questions,

What values are in #120 and #121?
What were you using #105 for?
Are you just picking up a block?

If so, are you trying to calculate to the center of the block?
Pick up an edge in X, and Y, and your Z at the top of the part?

This should work for center of the part in X and Y, but I am not going to set anything for Z.

I am also adding some minor error checking for the work offset value.

Please keep in mind, this is a quicky, but you should be close.

So, here I go:

M00(Move to point #1 in X, put desired work offset in #100)
M00(Press Cycle Start)
IF[#100 EQ #0]GOTO 3001
#101=[#100-53.]
IF[#101 LT 1.]GOTO 3002
IF[#101 GT 6.]GOTO 3003
#102=[[#100-53.]+5020.]
#103=[[#101*20.]+#102]
#110=#102

M00(Move to point #1 in Y)
M00(Press Cycle Start)

#112=#102+1.

M00(Move to point #2 in X)
M00(Press Cycle Start)

#111=#102

M00(Move to point #2 in Y)
M00(Press Cycle Start)

#113=#102+1.

[#[#103]]=[[#110+#111]/2]
[#[#103+1.]]=[[#112+#113]/2]

M30

N3001#3001=1(VARIABLE IS EMPTY)
N3002#3001=2(VALUE IS LESS THAN 54)
N3003#3001=3(VALUE IS MORE THAN 59)

Hope this helps!

[Osmanselim]

I am check it, thanks

best regards.