Circular Interpolation - Milling a Circle on a Shaft OD.


Results 1 to 5 of 5

Thread: Circular Interpolation - Milling a Circle on a Shaft OD.

  1. #1
    Registered
    Join Date
    Sep 2017
    Location
    United States
    Posts
    2
    Downloads
    0
    Uploads
    0

    Default Circular Interpolation - Milling a Circle on a Shaft OD.

    Hello CNCzone,

    Machine - Doosan 2600SY
    Cam - Edgecam 2017R2

    I am having a awful time trying to mill and wrapped circle on the OD of a shaft.

    I have been given this example code from doosan. Attached is a picture of the feature and gcode I want to create.

    G28U0V0W0
    G59G40G98G80
    M35
    T0303
    G97S500M3P12
    M90
    G28H0
    G0C0
    G0Z-50
    G0X80
    G01X65.F300
    G18W0H0
    G07.1 H50000
    G3K-20
    G1X80.F1000
    G07.1H0
    G18U0W0
    G0X200
    G28U0W0
    M5P12

    Running this code produces football shapes not circles.
    I am a little confused on what the 2 lines between the G07.1 are doing. Anyone have any insight?

    I have played with changing the (H50000) and (K-20) and can still only make football shaped no matter what I change them too.

    I have created circles by moving the Z and C together in small incremental moves but the circle comes out with a bunch of little flats and not a smooth finish.

    I am thinking that this feature can be done with a feeding the Z axis in a straight line while turning the C axis simultaneously.

    Has anyone been successful at creating this feature? What does your code look like?

    Any help would be greatly appreciated.
    Thanks,
    Tyler
    Circular Interpolation - Milling a Circle on a Shaft OD.-circular-interpolation-png

    Similar Threads:
    Attached Thumbnails Attached Thumbnails Circular Interpolation - Milling a Circle on a Shaft OD.-circular-interpolation-png  


  2. #2
    Registered Fletch_CNC's Avatar
    Join Date
    Jun 2015
    Location
    United States
    Posts
    96
    Downloads
    0
    Uploads
    0

    Default Re: Circular Interpolation - Milling a Circle on a Shaft OD.

    Quote Originally Posted by TChaseEngineer View Post
    Running this code produces football shapes not circles.
    I am a little confused on what the 2 lines between the G07.1 are doing. Anyone have any insight?

    I have played with changing the (H50000) and (K-20) and can still only make football shaped no matter what I change them too.
    I'm not 100% familiar with programming with Fanuc, but I'll toss out a couple ideas. First, the lines between the G07.1s define the shape you are wrapping around the shaft (so a G03 fuill circle, and a short G01 line). Second, are you sure you have the right diameter of shaft that you are working with? Also, have you tried changing the H50000 to C50., just to see if that makes any difference?

    I don't know if that helps any.

    ________________________________________________
    My blog: http://www.fletch1.com


  3. #3
    Registered
    Join Date
    Sep 2017
    Location
    United States
    Posts
    2
    Downloads
    0
    Uploads
    0

    Default Re: Circular Interpolation - Milling a Circle on a Shaft OD.

    Hey,

    Thanks for the response.

    I tried changing the H50 to C50 and that made the c axis spin about ~30 times.

    There is some relationship between H and K between the G07.1 that I don't understand. You would think you could just fudge one of the numbers and bring the football shape into a circle but no. I played with both numbers and it just stretches or squished the football shape. Sometimes it even rotates in 90deg to the z axis.

    I tried to hand write this without a G07.1 command and also no luck.

    Feeding Z in a straight line while rotating C at a constant feed creates a wrapped diamond shape.

    I played around with adding radius moves to try to get a circle,

    for example:
    2" OD
    1/4 EM
    1" OD Circle

    Z-1.25 C0;
    G1 X1.95 F10;
    G3 Z-.75 C30 R.375 F20;
    Z-.25 C0 R.375;
    Z-.75 C-30 R.375;
    Z-1.25 C0 R.375;
    X3;

    This somewhat creates a circle but for some reason the Yaxis wants to move so the EM does not stay on the center line of the stock which makes for an imperfect wrap on the OD.

    I am new to live tooling on lathes and would really like to figure this out! Why doesn't the Fanuc example work in my machine!!!



  4. #4
    Registered
    Join Date
    Jan 2009
    Location
    United States
    Posts
    77
    Downloads
    1
    Uploads
    0

    Default Re: Circular Interpolation - Milling a Circle on a Shaft OD.

    The H value should be X cutting rad. from spindle center (H65. or H65000) assuming your X Radius programming.



  5. #5
    Registered
    Join Date
    Sep 2010
    Location
    Australia
    Posts
    1196
    Downloads
    0
    Uploads
    0

    Default Re: Circular Interpolation - Milling a Circle on a Shaft OD.

    Quote Originally Posted by TChaseEngineer View Post
    Hey,

    Thanks for the response.

    I tried changing the H50 to C50 and that made the c axis spin about ~30 times.

    There is some relationship between H and K between the G07.1 that I don't understand. You would think you could just fudge one of the numbers and bring the football shape into a circle but no. I played with both numbers and it just stretches or squished the football shape. Sometimes it even rotates in 90deg to the z axis.

    I tried to hand write this without a G07.1 command and also no luck.

    Feeding Z in a straight line while rotating C at a constant feed creates a wrapped diamond shape.

    I played around with adding radius moves to try to get a circle,

    for example:
    2" OD
    1/4 EM
    1" OD Circle

    Z-1.25 C0;
    G1 X1.95 F10;
    G3 Z-.75 C30 R.375 F20;
    Z-.25 C0 R.375;
    Z-.75 C-30 R.375;
    Z-1.25 C0 R.375;
    X3;

    This somewhat creates a circle but for some reason the Yaxis wants to move so the EM does not stay on the center line of the stock which makes for an imperfect wrap on the OD.

    I am new to live tooling on lathes and would really like to figure this out! Why doesn't the Fanuc example work in my machine!!!
    Hello TChaseEngineer,
    The "H" value is expressed as the radius of the cylinder being cut irrespective of whether the Lathe is set for X Radius, or Diameter programming. The H address must be specified without a period, that is, in the number of Least Programmable Increments that equals the Radius of the Cylinder.

    You must also ensure that the axis that is parallel to the rotating axis is set in parameter 1022. In the case of a lathe with C axis, the parallel axis set in 1022 will be either the X (5) axis, or Y (6) (if the machine has a Y axis). Many make the mistake that Z is the parallel axis, but this is not so. Think of it as the axis parallel to the edge of the unwrapped cylinder (the face of the work-piece). As you will see, the X, and Y axis are parallel to the face of the work-piece, whereas, the Z axis is perpendicular to it. Generally, its most convenient to set this parameter to X (5) and in which case, G18 will be used to set the Circular Interpolation Plane. The syntax for Circular Interpolation will then be:

    G02 (G03) Z__C__R__;

    Note: I J K Circular Interpolation format can't be used in Cylindrical Interpolation Mode; only R format is allowed.

    Regards,

    Bill

    Last edited by angelw; 09-15-2017 at 05:13 AM.


Tags for this Thread

Posting Permissions

  • You may not post new threads
  • You may not post replies
  • You may not post attachments
  • You may not edit your posts
  •  


About CNCzone.com

    We are the largest and most active discussion forum for manufacturing industry. The site is 100% free to join and use, so join today!

Follow us on


Our Brands

Circular Interpolation - Milling a Circle on a Shaft OD.
Circular Interpolation - Milling a Circle on a Shaft OD.