3dprintforums logo

CNCzone Network:  RFQwork :: 3Dprintforums :: Welderzone :: Google+ :: Our Facebook :: Twitter :: SiteMap



Results 1 to 6 of 6

Thread: 1/4 NPT External thread program

  1. #1
    Registered
    Join Date
    Sep 2005
    Location
    USA
    Posts
    37
    Downloads
    0
    Uploads
    0
    Rep Power
    0

    1/4 NPT External thread program

    Can someone help me with programming 1/4 npt external using G76 (fanuc O-T). I do not know what values to put in for the thread dimensions. Thanks!

    Similar Threads:


  2. #2
    Registered CNCRim's Avatar
    Join Date
    Feb 2006
    Location
    usa
    Posts
    949
    Downloads
    0
    Uploads
    0
    Rep Power
    9
    .54 dia start point with 1.75deg per side. Is it help.

    The best way to learn is trial error.


  3. #3
    Registered
    Join Date
    Mar 2007
    Location
    United States of America
    Posts
    6
    Downloads
    0
    Uploads
    0
    Rep Power
    0
    I'm threading 1/4 npt threads on a fanuc ot controled cnc lathe. Can anyone give me some help on the second line of info using G76?



  4. #4
    Registered
    Join Date
    Jul 2005
    Location
    Canada
    Posts
    12114
    Downloads
    0
    Uploads
    0
    Rep Power
    21
    Lead is 18 threads per inch, taper is 0.0625" per inch diameter measure, finish diameter is around 0.56", length is around 1/2".

    An open mind is a virtue...so long as all the common sense has not leaked out.


  5. #5
    Registered
    Join Date
    May 2007
    Location
    USA
    Posts
    940
    Downloads
    0
    Uploads
    0
    Rep Power
    7
    Thread ending point figured at center of 16ER 18 NPT insert and L4 dimension from Machinery's Handbook.

    Finish turn .016R insert
    X.3768Z0
    G3X.4065Z-.0062R.021
    G1X.5249Z-.0653
    X.54Z-.3077
    Z-?

    Finish turn .031R insert
    X.3468Z0
    G3X.3977Z-.0105R.036
    G1X.5245Z-.0739
    X.54Z-.3224
    Z-?

    Thread 1/4-18 NPT external
    X.58Z.3
    G76P000155Q30
    G76X.467Z-.634P444Q150R-.0291F.05556

    Changing starting point or ending point will require R to be modified. R=tan(1+47/60)*(start point + end point) unless both points are the same sign, in which case you would subtract them.

    Single block G76
    X.58Z.3
    G76X.467Z-.634I-.0291K.0444D150F.0556A50.

    Did one of these work okay for you?



  6. #6
    Registered
    Join Date
    May 2007
    Location
    USA
    Posts
    940
    Downloads
    0
    Uploads
    0
    Rep Power
    7
    Apparently my examples didn't work. What did you finally wind up with?



Tags for this Thread

Posting Permissions



About CNCzone.com

    We are the largest and most active discussion forum from DIY CNC Machines to the Cad/Cam software to run them. The site is 100% free to join and use, so join today!

Follow us on

Facebook Dribbble RSS Feed