Fanuc parts counter

[scubanick]

I have a miyano lathe with a Ge series Fanuc O-T controller
i want to add into my program if possible
a way to when it runs lets say 50 parts the machine will stop
and wait for the operator to either hit cycle start again
or clear the count then hit cycle start
something to have them run only a certain number of parts
to remove from the machine check the last one of that bactch
then start back up again..i dont do macro programming
so is there a way to do it in standard G-code.

thanks
Nick

[M-man]

Do your controll have the macro B option?
Otherwise you could use a subprogram and call the machining prg 50 times.

EX.
%
O1000
M98 P2000 L50
M30

O2000
Prog..

[scubanick]

im not sure about the B marco option

i was tryin to stay away from the subprogram deal
i was hoping there was a way for me to just specify a line of code
near the end of the program

[M-man]

I ve got the Part counter option, Just define number of parts at Mdi/settings and use M54 in program to count..

[M-man]

#100=0
N10
MACHINING
#100=#100+1
If[#100EQ50]goto500
goto10
N50M30


Mabe this will work

[scubanick]

Lets Say This Is My Program
And I Want It To Stop At 50 Parts
Would U Mind Showing Me Where In This Program To Place
What You Are Referrign To With The M54


67a7519ho1 7/7/2006)
T0606m05(bar Stop)
G00x0.1z0.0
M12
G00x2.z3.
T0600
M01
N001 G50 S3000
N002 T0100
N003 G00 G96 S249 M03 T0101
N004 M08
N005 G00 X0.7 Z2.
N006 G00 Z2.1
N007 X0.5988
N008 Z0.1
N009 G01 Z0 F0.007
N010 X-0.0312
N011 G00 Z2.1
N012 X0.7
N013 Z2.
(cnmg .015)
N014 X0.9
N015 Z0.0094
N016 X0.6452
N017 G01 X0.4452 S250
N018 Z-0.154
N019 X0.5938
N020 G03 X0.645 Z-0.1796 I0 K-0.0256
N021 G01 Z-0.2596
N022 G00 X0.845
N023 Z0.0094
N024 X0.595
N025 G01 X0.395
N026 Z-0.154
N027 X0.4452
N028 G00 X0.9
N029 Z0.0094
N030 X0.575
N031 G01 X0.375
N032 Z-0.164
N033 X0.5938
N034 G03 X0.625 Z-0.1796 I0 K-0.0156
N035 G01 Z-0.2596
N036 G00 X0.9
N037 Z2.
N038 X0.7
(.25 Drill)
N039 G00 Z2. M09
N040 T0100
N041 M01
N042 T0200
N043 G00 G97 S1528 M03 T0202
N044 M08
N045 G00 X0.7 Z2.
N046 G00 X0 Z1.
N047 Z0.1
N048 G01 Z-0.15 F0.003
N049 G00 Z0.1
N050 Z-0.1
N051 G01 Z-0.3
N052 G00 Z0.1
N053 Z-0.25
N054 G01 Z-0.45
N055 G00 Z0.1
N056 Z-0.4
N057 G01 Z-0.5751
N058 G00 Z1.
N059 X0.7 Z2.
(.125 Wide Part Off Tool)
N060 G00 Z2. M09
N061 T0200
N062 M01
N063 T0500
N064 G00 G96 S250 M03 T0505
N065 M08
N066 G00 X0.7 Z2.
N067 G00 X0.9
N068 Z-0.3199
N069 X0.8574
N070 G01 X0.6574 F0.02
N071 X0.6092 Z-0.344 F0.003
N072 X0.14
N073 G00 X0.9
N074 Z2.
N075 X0.7
N076 G00 X0.64 Z2. M09
N077 T0500
N078 M30

[M-man]

If you got the M54 option for part count, then you could put out your code just before M30 and change M30 to M99 to repeat prog.. The number of parts must be sett manually in Mdi mode on the system/setting screen. (I think it is called so)..
But if you dont got this option you got to use a macro and if you dont have the Macro B option you must use sub prog.

[M-man]

67a7519ho1 7/7/2006)
#100=0
#101=50 -- 50 = part numbers
N500
T0606m05(bar Stop)
G00x0.1z0.0
M12
G00x2.z3.
T0600
M01
N001 G50 S3000
N002 T0100
N003 G00 G96 S249 M03 T0101
N004 M08
N005 G00 X0.7 Z2.
N006 G00 Z2.1
N007 X0.5988
N008 Z0.1
N009 G01 Z0 F0.007
N010 X-0.0312
N011 G00 Z2.1
N012 X0.7
N013 Z2.
(cnmg .015)
N014 X0.9
N015 Z0.0094
N016 X0.6452
N017 G01 X0.4452 S250
N018 Z-0.154
N019 X0.5938
N020 G03 X0.645 Z-0.1796 I0 K-0.0256
N021 G01 Z-0.2596
N022 G00 X0.845
N023 Z0.0094
N024 X0.595
N025 G01 X0.395
N026 Z-0.154
N027 X0.4452
N028 G00 X0.9
N029 Z0.0094
N030 X0.575
N031 G01 X0.375
N032 Z-0.164
N033 X0.5938
N034 G03 X0.625 Z-0.1796 I0 K-0.0156
N035 G01 Z-0.2596
N036 G00 X0.9
N037 Z2.
N038 X0.7
(.25 Drill)
N039 G00 Z2. M09
N040 T0100
N041 M01
N042 T0200
N043 G00 G97 S1528 M03 T0202
N044 M08
N045 G00 X0.7 Z2.
N046 G00 X0 Z1.
N047 Z0.1
N048 G01 Z-0.15 F0.003
N049 G00 Z0.1
N050 Z-0.1
N051 G01 Z-0.3
N052 G00 Z0.1
N053 Z-0.25
N054 G01 Z-0.45
N055 G00 Z0.1
N056 Z-0.4
N057 G01 Z-0.5751
N058 G00 Z1.
N059 X0.7 Z2.
(.125 Wide Part Off Tool)
N060 G00 Z2. M09
N061 T0200
N062 M01
N063 T0500
N064 G00 G96 S250 M03 T0505
N065 M08
N066 G00 X0.7 Z2.
N067 G00 X0.9
N068 Z-0.3199
N069 X0.8574
N070 G01 X0.6574 F0.02
N071 X0.6092 Z-0.344 F0.003
N072 X0.14
N073 G00 X0.9
N074 Z2.
N075 X0.7
N076 G00 X0.64 Z2. M09
N077 T0500
#100=100+1
If[#100EQ#101]goto600
N078 Goto500
N600 M30

[scubanick]

ok now on the mid/setting page ???under macro??
i go to variables column and put 50 where at??
which variable #

[NC Cams]

Please revisit post #8 as you read the following:

The "counter" is essentially the 2 lines after N077. The "if" statement provides the count and stop/repeat logic "decider".

This in concert with the two lines added at the very beginning of the program (the ones with the #) should count the parts and stop the program just as you asked.

The amount of parts you want is done here:

#101=50 -- 50 = part numbers

[scubanick]

ill give it a try
thanks

[Jarwalcot]

Run Hours and Part Count Display: 907.4