program format

[fenix728]

hello guys , can anyone tell me or send me the right format for : starting program,starting tool ending tool an ending program its been a few years since i have worked on a fadal machine ,and i am getting alarm, i thank you very much in advance, any help its good, because my memory is not.

[Jason S]

Here is a mixed bag for ya. I run format 2.

%
O1(P/N OP)
G90 G80 G70 G40 G17 G0
(2.5" MITS )
(MILL 1.00 DIM )
M6 T1
S2292 M3
G0 G90 X1.55 Y-1.125 E1
H1 Z1. M8
G0 Z0.3
G1 Z0.11 F60.
X-6.55
G0 Z1.
X1.55
Z0.21
G1 Z0.02
X-6.55
G0 Z1.
X1.55
Z0.19
G1 Z0
X-6.55
G0 Z1.
M9 M5
G0 Z0.H0.
M1
(#5 C'DRILL)
M6 T2
S1000 M3
G0 G90 X-4.37 Y-0.5 E1
H2 Z1. M8
M46
G98 G82 X-4.37 Y-0.5 Z-0.4452 R0.1 P360 F3.5
X-2.5 Y-1.13
X-2.06 Y-0.5
Y-1.75
G80
M9 M5
G0 Z0.H0.
M1
(13/16" DRILL)
M6 T3
S470 M3
G0 G90 X-2.06 Y-1.75 E1
H3 Z1. M8
M47
G98 G83 X-2.06 Y-1.75 Z-0.7441 R0.1 Q0.125 F4.7
Y-0.5
X-4.37
G80
M9 M5
G0 Z0.H0.
M1
(9/16 DRILL)
M6 T4
S679 M3
G0 G90 X-2.5 Y-1.13 E1
H4 Z1. M8
M47
G98 G83 X-2.5 Y-1.13 Z-1.269 R0.1 Q0.125 F4.074
G80
M9 M5
G0 Z0.H0.
M1
(1/2" ENDMILL)
M6 T5
S1500 M3
G0 G90 X-2.06 Y-1.75 E1
H5 Z1. M8
G0 Z0.1
G1 Z-0.5 F2.
G41 X-1.8725 D5 F8.
G3 I-0.1875 J0
G1 G40 X-2.06
G0 Z1.
Y-0.5
Z0.1
G1 Z-0.5 F2.
G41 X-1.8725 D5 F8.
G3 I-0.1875 J0
G1 G40 X-2.06
G0 Z1.
X-4.37
Z0.1
G1 Z-0.5 F2.
G41 X-4.1825 D5 F8.
G3 I-0.1875 J0
G1 G40 X-4.37
G0 Z1.
M9 M5
G0 Z0.H0.
G0 X0. Y8. E0
M30
%

[Neal]

Tell me what the alarm is and I can most likely tell what to look for.

Neal

[denmar]

O1(P/N OP)
G90 G0X0Y0S2292M3 (PROG HOME)
(2.5" MITS )
(MILL 1.00 DIM )
X1.55 Y-1.125
H1D1Z0M7 (THESE WILL BRING YOU T#1 ABOVE THE PART)
G1 Z0.11 F60. (ASSUMING YOUR OFFSET IS .100 AVOBE THE PART)
X-6.55
G0 Z1.
X1.55
Z0
G1 Z-.120F60.
X-6.55
G0 Z1.
X1.55
Z0
G1F60.Z-0.140
X-6.55
G0 Z0
M9 M5
G28
M6 T2 (CENTER DRILL)
G0G90S1000M3X0Y0
X-4.37 Y-0.5
H2ZOM7
G98 G82 X-4.37 Y-0.5 Z-0.4452 R0+.1F3.5
X-2.5 Y-1.13
X-2.06 Y-0.5
Y-1.75
G80
M9 M5
G28
M6T1
M2

[DareBee]

O1(P/N OP)

G90 G80 G70 G40 G17 G0 (These codes are best to be safe)
If you want this is a good place to put X0Y0
M6 T1 (loads TOOL)
I recommend S2292 M3 here


G90 G0X0Y0S2292M3 (PROG HOME)
(2.5" MITS )
(MILL 1.00 DIM )
X1.55 Y-1.125
H1D1Z0M7 (THESE WILL BRING YOU T#1 ABOVE THE PART) This is likely the biggest problem AFAIK M7 does not exist
G1 Z0.11 F60. (ASSUMING YOUR OFFSET IS SET TO ZERO.100 AVOBE THE PART)
X-6.55
G0 Z1.
X1.55
Z0
G1 Z-.120F60.
X-6.55
G0 Z1.
X1.55
Z0
G1F60.Z-0.140
X-6.55
G0 Z0
M9 M5
G28
M6 T2 (CENTER DRILL)
G0G90S1000M3X0Y0
X-4.37 Y-0.5
H2ZOM7 ZO needs to be Z0 and another M7?
G98 G82 X-4.37 Y-0.5 Z-0.4452 R0+.1F3.5
X-2.5 Y-1.13
X-2.06 Y-0.5
Y-1.75
G80
M9 M5
G28
M6T1
M2

No time to continue - have a nice day

[denmar]

G90X0Y0S2292M3( G80 G70 G40 G17 G0/these codes are modal)
M6 T1 (every time prog starts will try a toll change)(
START WITH TOOL 1 IN THE SPINDLE.
(2.5" MITS )
(MILL 1.00 DIM )
X1.55 Y-1.125
H1D1Z0M7 (THESE WILL BRING YOU T#1 ABOVE THE PART) COOLANT ON, DIAMETRE #1 (M8 IS FOR MIST)
G1 Z-0.11 F60. (ASSUMING YOUR TOOL OFFSET IS SET TO 0.100 ABOVE THE PART)
X-6.55(G42; TURN ON CUTTER COMP)
G0 Z1.
X1.55
Z0
G1 Z-.120F60.
X-6.55
G0 Z1.
X1.55
Z0
G1F60.Z-0.140
X-6.55
G0 Z.20G40( COMP OFF)
M9 M5
G28
M6 T2 (CENTER DRILL)
G0G90S1000M3X0Y0
X-4.37 Y-0.5
H2ZOM7 ZO needs to be Z0 and another M7? (0.100 ABOVE THE PART)
(HAVE TO TURN COOLANT ON BECAUSE THERES AN M9 ABOVE!!
G98 G82 X-4.37 Y-0.5 Z-0.4452 R0+.1F3.5 ( IF YOU WANT DRILL TO THIS DEPTH, ADD UP THE 0.100= Z-0.5452)
X-2.5 Y-1.13
X-2.06 Y-0.5
Y-1.75
G80
M9 M5
G28
M6T1
M2