Fadal quick code sheet from years back

[Delw]

Years ago (1990) Fadal Came out with these little quick code cards. we always kept them by the machine for reference. I couldnt find mine for about 3 years and then low and behold I found 4 of them, they are on a 5x 6 laminated card front and back.
I will try to scan a copy of the front and back of the org.
Thought since I had some time to type them up, I would post them. just copy and paste them then print and laminate, keep them next to your machines.

Front Left Colum

• G00 POINT TO POINT POSITIONING
• G01 LINEAR INTERPOLATION
• G02 CIRCULAR INTERPOLATION
  (ARC CLOCKWISE)
• G03 CIRCULAR INTERPOLATION
  (ARC COUNTER CLOCKWISE)
• G04 DWELL (P-WORD MILLIESECONDS)
• G05 NON-MODAL RAPID
• G08 ACCELERATION (NO RAMPS)
• G09 DECELERATION (RAMPS)
• G10 PROGRAMMING DATA INPUT
  (L02=FIXTURE X,Y,Z P=#,
  L10=LENGTH,P=#, R0=AMT,
  L12=DIAMETER,P=#,R0=AMOUNT,
  L100-L109=R VALUES,P=AMT)
• G15 YZ CIRULAR INTERPOLATION
  (WITH A AXIS)
• G16 XY CIRULAR INTERPOLATION
  (WITH C AXIS)
• G17 XY PLANE
  (Q WORD FOR A AXIS MAPPING)
• G18 ZX PLANE
• G19 YZ PLANE
• G20 INCH PROGRAMMING
• G21 METRIC PROGRAMMING
• G28 RETURN TO ZERO
• G29 RETURN FROM ZERO
• G40 CUTTER COMPENSATION CANCEL
• G41 CUTTER COMPENSATION LEFT
• G42 CUTTER COMPENSATION RIGHT
• G43 TOOL LENGTH COMPENSATION POS.
• G44 TOOL LENGTH COMPENSATION NEG.
• G45 TOOL OFFSET SINGLE EXPANSION
• G46 TOOL OFFSET SINGLE REDUCTION
• G47 TOOL OFFSET DOUBLE EXPANSION
• G48 TOOL OFFSET DOUBLE REDUCTION
• G49 TOOL LENGTH OFFSET CANCEL
• G50 RAMP SLOPE CONTROL CANCEL
• G50.1 MIRROR IMAGE CANCEL
• G51 RAMP SLOPE CONTROL
  (R0=RAMP SPEED VALUESOF .5-2.
  +SIGN=Z AXIS, -SIGN=XY AXIS)
• G51.1 MIRROR IMAGE
• G52 LOCAL COORDINATE SYSTEM
• G53 MACHINE COORDINATE SYSTEM
• G54-59 FIXTURE OFFSETS

Front right colum

• G66 MODAL SUBROUTINE CALL
  (L=SUBROUTINE)
• G67 MODAL SUBOUTINE CANCEL
• G68 ROTATION(R0=ANGLE
  X,Y=CENTER OF ROTATION)
• G69 ROTATION CANCEL
• G70 INCH PROGRAMMING
• G71 METRIC PROGRAMMING
• G73 PECK DRILL (Q= STEPSIZE
  I= INITIAL PECK J=REDUCING VALUE
  K=MINIMUM PECK)
• G74 LEFT HAND TAP
  FORMAT 1 (Q=THREAD LEAD, F=RPM)
  FORMAT 2 (F=FEEDRATE, NO Q)
• G75 TAPPING HEAD CYCLE
  (Q=THREAD LEAD, F=RPM)
• G76 FINE BORING
  (Q=AMOUNT OF Y+ SHIFT OR
  I=AMOUNT OF X SHIFT, J=AMOUNT
  OF Y SHIFT
• G80 FIXED CYCLE CANCEL
• G81 DRILL, SPOT DRILL
• G82 DRILL, COUNTERBORE
  (P=MILLISECONDS)
• G83 DEEP HOLE CYCLE (Q=STEPSIZE
  I=INITIAL PECK, J=REDUCING VALUE
  K=MINIMUM PECK
• G84 RIGHT HAND TAP
  FORMAT 1 (Q=THREAD LEAD, F=RPM)
  FORMAT 2 (F=FEEDRATE, NO Q)
• G85 BORE IN/OUT
• G86 BORE IN/SPINDLE OFF/RAPID OUT
• G87 BORE IN.OUT
• G88 BORE IN/DWELL/OUT
  (P=MILLISECONDS)
• G89 BORE IN/DWELL/OUT
  (P=MILLISECONDS)
• G90 ABSOLUTE POSITIONING
• G91 INCREMENTAL POSITIONING
• G91.1 HIGH SPEED EXCECUTION
• G91.2 HIGH SPEED EXCECUTION CANCLE
• G92 ABSOLUTE PRESET
• G93 1/T FEEDRATE SPECIFICATION
• G94 FEEDRATE SPECIFICATION DPM,IPM
• G98 RETURN TO INITIAL PLANE
• G99 RETURN TO R0 CLEARANCE PLANE

BACK SIDE

• L9201 ENGRAVING (R1+0=STD R1+1=STEN R1+2=SERIAL STD R1+3=SERIAL STEN,
  R2=HEIGHT, R3= ANGLE, R4=SERIAL INCREMENT 1-9,
  R0=CLEARANCE PLANE, Z=FINAL DEPTH, F=FEED RATE)
• L93NN BOLT CIRCLE R0=I, R1=J, R2=ANGULAR STEP, NN=AMOUNT OF HOLES)
• L94NN MILL BORING CYCLE CCW (R0=FEED, R1=DIA. OF HOLES, NN=REPETITIONS)
• L95NN MILL BORING CYCLE CW (R0=FEED, R1=DIA. OF HOLES, NN=REPETITIONS)
• L9601 RECTANGULAR POCKET CCW (R0=FEED, R1=RAD. ON TOOL ,R2=X, R3=Y)
• L9701 RECTANGULAR POCKET CW (R0=FEED, R1=RAD. ON TOOL ,R2=X, R3=Y)
• L9801 CIRCULAR POCKET CCW (R0=FEED, R1=RAD. ON TOOL ,R2=DIA. OF HOLE)
• L9901 CIRCULAR POCKET CW (R0=FEED, R1=RAD. ON TOOL ,R2=DIA. OF HOLE)

NOTE: INPUT OF THE R PARAMETER REQUIERS THE SIGN (+ OR -)

• M00 PROGRAM STOP
• M01 OPTIONAL START
• M02 END OF PROGRAM (FORMAT 1)
• M03 SPINDLE ON CLOCKWISE
• M04 SPINDLE ON COUNTERCLOCKWISE
• M05 SPINDLE OFF
• M06 TOOL CHANGE
• M07 COOLANT ON FUNCTION
• M08 COOLANT ON FUNCTION
• M09 COOLANT OFF FUNCTION
• M10 CANCEL RECIPROCATION
• M11 X AXIS RECIPROCATION
• M12 Y AXIS RECIPROCATION
• M13 Z AXIS RECIPROCATION
• M14 B AXIS RECIPROCATION
• M15 A AXIS RECIPROCATION
• M17 END OF SUBROUTINE
• M18 CYCLE CUSHMAN INDEXER
• M19 SPINDLE STOP/ORIENT
• M20 CYCLE INDEXER
• M30 END OF ALL SUBROUTINES
  END OF PROGRAM(FORMAT 2)
• M41 LOW RANGE RPM
• M42 HIGH RANGE RPM
• M45 EXECUTE FIXED CYCLE
• M46 SET POSITIVE APPROACH
• M47 CANCEL POSITIVE APPROACH
• M48 FEEDRATE AND RPM POT-IN
• M49 FEEDRATE AND RPM POT-OUT
• M60-69 USER ATTACHED DEVICES
• M96 CANCEL INTERSECTIONAL CRC
• M97 INTERSECTIONAL CRC
• M98 EXECUTE SUB PROGRAM
  (P=PROGRAM #, L=REPETITIONS)
• M99 END OF SUB PROGRAM

Please double check these as my typing and eye sight sucks, I did go through them a few times to verify.

[gsrmmeza]

Here's a link to the newer version.



http://www.compumachine.com/Support/...gram_Codes.pdf

[Delw]

well damn if I would have known that it would have saved me lots of typing, Thanks for the heads up.