| |
| Home Page | Mark Forums Read | Today's Posts | My Replies | Classifieds | Reviews | Photo Gallery | Web Links | Share Files | Advertise With Us | Ad List |
| |||||||
| Fadal Discuss Fadal machinery here! |
| | |
| This forum is sponsored by: |
 |
| | LinkBack | Thread Tools | Search this Thread | Display Modes |
|
#1
 
05-07-2008, 09:31 AM
| |||
| |||
I have a few hundred parts that need five ops on.c' drill, 2 different size drills, c' bore and tap. I want to set them up in three vises and use fixture offsets. But i want to run all three with c' drill then next tool and so on.will this work.4020 FADAL 88HS CONTROL L0100 xxxx xxxx xxxx m17 m30 L0200 xxx xxx xxx m17 m30 etc G00 G17 G40 G70 G80 G90 G54 t1m6 L0101 g56 L0101 G57 L0101 G00 G17 G40 G70 G80 G90 G54 T2M6 L0201 G56 L0201 G57 L0201 ETC. Last edited by markjb; 05-07-2008 at 10:47 AM.    |
|
#2
05-08-2008, 05:14 AM
| |||
| |||
| % O1* 3 FIXTURE DRILL, TAP, AND C-BORE PROG * X0 Y0 CENTER Z0 TOP OF MATERIAL * T1 CENTER DRILL * T2 .1875 DRILL * T3 .201 DRILL * T4 1/4-20 CUT TAP (G84) * T5 .3125 ENDMILL (C-BORE ) L100 G81X0Y0Z-.1R.1F20. X2. G80 G0Z1. M17 L200 G83X2.Y0Z-.5R.1Q.1F20.P.01 G80 G0Z1. M17 L300 G83X0Y0Z-.75R.1Q.1F20.P.01 G80 G0Z1. M17 L400 G84X0Y0Z-.5R.4Q.05F500. G80 G0Z1. M17 L500 G82X2.Y0Z-.3125R.1F15.P250. G80 G0Z1. m17 m30 G00 G17 G40 G70 G80 G90 M6T1 M3S6500 X0Y0G54 H1Z.1M7 L101 g56 Z.1 L101 G57 Z.1 L101 G0Z3. M5M9 G49Z0 M1 G00 G17 G40 G70 G80 G90 M6T2 M3S6500 X2.Y0G57 H2Z.1M7 L201 X2.Y0G56 Z.1 L201 X2.Y0G54 Z.1 L201 G0Z3. M5M9 G49Z0 M1 G00 G17 G40 G70 G80 G90 M6T3 M3S6500 X0Y0G54 H2Z.1M7 L301 X0Y0G56 Z.1 L301 X0Y0G57 Z.1 L301 G0Z3. M5M9 G49Z0 M1 G00 G17 G40 G70 G80 G90 M6T4 M3S500 X0Y0G57 H4Z.4M7 L401 X0Y0G56 Z.4 L401 X0Y0G54 Z.4 L401 G0Z3. M5M9 G49Z0 M1 G00 G17 G40 G70 G80 G90 M6T5 M3S2500 X2.Y0G54 H5Z.1M7 L501 X2.Y0G56 Z.1 L501 X2.Y0G57 Z.1 L501 G0Z3. M5M9 X0Y0E0 G49Z0 M1 G00 G17 G40 G70 G80 G90 M6T1 M2 % |
|
#3
05-08-2008, 06:52 PM
| ||||
| ||||
| I do this all the time, using 4 parts in 2 vises..and I use the fixture offset E 'cause it's easier to recognize, I can number each part with a simple 1,2,3,4, and, well, I'm just used to it. It looks something like this: ....program definitions..... M17 M30 G0 X0 Y0 E1 L101 G0 X0 Y0 E2 L101 G0 X0 Y0 E3 L101 G0 X0 Y0 E4 L101 G0 X0 Y0 E1 L201 G0 X0 Y0 E2 L201 G0 X0 Y0 E3 L201 G0 X0 Y0 E4 L201 G0 X0 Y0 E1 L301 G0 X0 Y0 E2 L301 G0 X0 Y0 E3 L301 G0 X0 Y0 E4 L301 G0 X0 Y0 E1 L401 G0 X0 Y0 E2 L401 G0 X0 Y0 E3 L401 G0 X0 Y0 E4 L401 M9 H0 Z0 M5 G0 G90 X0 Y0 E0 M2 % |
|
#7
03-16-2009, 06:09 AM
| |||
| |||
| L100 G0 X0 Y0 ... ... M17 M30 E1 L101 E2 L101 E3 L101 E4 L101 E1 L201 E2 L201 E3 L201 E4 L201 E1 L301 E2 L301 E3 L301 E4 L301 E1 L401 E2 L401 E3 L401 E4 L401 M9 H0 Z0 M5 G0 G90 X0 Y0 E0 M2 PUT THE G0X0Y0 in the beginning 0f the subprogram- only to be used by lazy people like myself.. |
|
| | |
| Currently Active Users Viewing This Thread: 1 (0 members and 1 guests) | |
| Thread Tools | Search this Thread |
| Display Modes | |
| |
Similar Threads | ||||
| Thread | Thread Starter | Forum | Replies | Last Post |
| Help on programing the PIC in MM2001 | DreamerM | PIC Programing / Design | 2 | 08-29-2011 08:56 PM |
| 0-M programing help please | venomgrrrl | Fanuc | 22 | 12-08-2007 12:51 AM |
| CNC programing | Fryzss | General CNC (Mill and Lathe) Control Software (NC) | 8 | 10-27-2007 11:33 AM |
| Help on programing the PIC in MM2001 | DreamerM | General Electronics Discussion | 0 | 03-18-2007 06:22 AM |
| CAM programing | kenlambert | G-Code Programing | 1 | 02-03-2006 01:03 AM |
| | |
Linear Mode
