Need Help!- Haas VF 6 post

[greenweanie]

I have a Haas VF3 and a VF6 here at work..Recently my hard drive crashed and had to start over from scratch. The post processor files I had weren't backed up either. I am trying to make another, or modify one I have downloaded from our reseller. But I am not getting that far. One of them I tried to edit, keeps posting G49 codes at each toolchange. That is fine for our VF3 but we have a Renishaw probe on the VF6 causing all my tooling to have negative offsets...when it posts a G49 the tool dives into the table.
Another one I tried to edit keeps posting a G-1 code on the canned drill cycles. I just upgraded to 2010 R2 yesterday and I am trying to get some of the extra features to work still. We just have the basic wire frame entry level milling package... does the probe feature work on that version? Also any help with the VF posts would be very much appreciated... P.S. our reseller is very limited on any tech support.

[rider23]

There is a copy of a Vf 6 post at this thread

http://cnczone.com/forums/showthread.php?t=92470

and a VF 3 with rotary at this thread

http://cnczone.com/forums/showthread.php?t=94332

[greenweanie]

Thanks for the links, but I've tried those, and all those are for rotary setups...I am just trying to find a basic one w/o the 4th axis

[greenweanie]

Ok, i have got one working but there is a few things I can't figure out how to change. I want it to post the coolant on before the spindle starts rotating. Right now it posts after it rapids down above the part after the spindles is spinning. Also it is currently posting both M08 AND M88 codes. Is there a way for it to choose only one depending on if through coolant is checked or not in the toolstore?

[jtreanor]

Hello greenweanie,

G-1 output for canned cycles is usually because the
NC-Stye - "Hole Cycle G-Codes" are blank.
or possibly the canned cycle numbers exceed the
capacity defined in the FORMAT TABLE "Hole Cycles - G Code"

Look in the *[CORE TOOLCHANGE CONSTRUCTOR]*
for the G49 that you don't want.

if coolant only comes on after the rapid move
remove [COOLANT] from the "Rapid After Toolchange" constructor

add coolant control to the *[CORE TOOLCHANGE CONSTRUCTOR]*
*EXAMPLE below
*These settings create output only if COOLANT is ON
*%DONT-OUTPUT is used for if COOLANT is already OFF
*then DONT-OUTPUT M9 or M89
*%OUTPUT-IF-CHANGED sets it back to ALLOW CHANGE

*[CORE TOOLCHANGE CONSTRUCTOR]*
;CODE:%IF #COOL=9 %THEN %DONT-OUTPUT=#COOL
;CODE:%IF #THROUGHTOOL1=89 %THEN %DONT-OUTPUT=#THROUGHTOOL1

([COMMENT])
[DELETE][SAFEBLKNUM][<C>TURRETNO] M06
[<C>ABS-INC][<C>FEEDMODEGCODE][NEXTTOOL][<C>SPEED][<C>SPINDIR]
[WORKGCODE][COOLANT]
[COOLTHROTOOL]
;CODE:%OUTPUT-IF-CHANGED=#COOL,#THROUGHTOOL1

[henriktrolle]

Hi if you need a Haas VF6 Postprocessor then i can email you mine. it works fine have no problem with that. i can mail it on monday when i come to work. by the way i also have one for VF3 and VF4