Citizen Question
For the Citizen experts. Is there a way to incorporate the cutoff process and start position process directly into the program rather than having to do it manually?
What macros does it read for the cutoff, and for the move to start position? These questions are for a L20 M7 and M8
Thanks in advance
Brett
Similar Threads:
Yes there is a way.
Load the attached file into the machine and call it as a SUB program at the beginning of $1. MAKE $2 WAIT UNTIL IT IS COMPLETED.
$1 ................................. $2
M98P322
!2L322 ........................ !1L322
This is for the L7-20. There is NO M7 or M8 machine.
You need to call the cutoff tool into position and position the stock FIRST!!
Thanks for the reply. I new to citizens and was referring to the model # on the manuals, it says 5m7 or 5m8 which is where i got the m7 m8 from. Anyway thanks for the information. And what excatly is program 322?
If i have to position the cutoff tool first would something like this work
$1................................................ .................$2
IF[#5041LT0]GOTO500......................................!L322
T0100
G0X[#814+.05]
M98P322
N500
!L322
My goal in this scenario is to put a safety check in place in case guys forget to move to start position which seems to happen regulary.
OH
Didnt see the attached file! Thank you!!
This program will got into alarm if the cutoff tool is not in position. The screen will read "Call Cutoff".
If you do a tool call as you show it will add cycle time on EVERY cycle.
FYI,
5m7 = L5-20 (5th Generation L20), Type VII
5m8 = L5-20 (5th Generation L20), Type VIII (Added capibility, Gangblock)
See the attached file for a line-by-line explanation of what will be done by that program.
"Train the operators, but first protect the equipment!"
The M stands for Mitsubishi, F stands for Fanuc
Just to expand on your breakdown, M is for Mits, F is for FanucOriginally Posted by cogsman1
I am trying to use this on my L6-32 but i am having trouble with the G53 -#818. It wants to go to minus what is in my mc data from machine zero. It is not going to the start position.
For that machine change that one line to be
G53Z#872-#818
The system settings are different between some models.
thank you. I am trying to learn how all this stuff works. Kinda got thrown to the wolves with the swiss machines. Learning as i go though..
I am still having problems with this on the L6-32. I changed the g53 line to #872-#818. The first time I ran the program it worked just like it should, went right to start position after cutoff. Now every time after that It wants to go forward toward the guide bushing and alarms out.
what alarm?
Control the process, not the product!
Machining is more science than art, master the science and the artistry will be evident.
Z axis over travel. Traveling toward the GB this time.
Well, are you in OT?
Can you move Z1 in manual?
When you run your code, what is the MC COORd for Z1?
Control the process, not the product!
Machining is more science than art, master the science and the artistry will be evident.
What does the "distance to go" show? What axis' still have movement to go?
just Z1 axis list a distance to go. It is something like 10 inches positive. If i go back to G53 z-#818 it also alarms but a negative distance to go.
There are only two options and one of them is correct. Be sure you are entering them in correctly.
G53Z-#818 (Z - #818 )
G53Z#872-#818
Ok i am certain i have entered everything in correctly. Like i said though if you do this first thing when the machine is powered up it works. if i manually do a start position or if i run this start position prog twice, the second time it does not work.
Here is what i just took out of the machine
O322(START-POSITION )
$1
IF[#858NE#816]GOTO30
IF[ABS[#5043]GT[#814/2]]GOTO30
IF[#5043GT.01]OR[#5043LT-.01]GOTO1
IF[#5041GT#824+.02]OR[#5041LT#824-.02]GOTO1
GOTO7
N1
M6(CLOSE COLLET)
(CUTOFF)
T0100
S1=#817M3
G0X#814+.1T1
G99G1X#824F#822
G4U.5
M5
N7
(START POSITION)
IF[#5022EQ-#818]GOTO991
M7
G4U.8
G0X#824W0T0
G53Z#872-#818
M6
N991
M99
N30
#3000=70(-CALL-CUTOFF)
$2
$3
$0
A
#814=0000007500
#815=0000001000
#816=0000001000
#817=0003000000
#822=0000000020
#824=-000000500
#818=0000015000
#819=0000001000
#820=0000000000
#821=0000000000
#990=0000030000
#991=0000056000
#992=0000064000
#893=0000000000
%
Try this change
(START POSITION)
IF[#5022EQ[#872-#818]]GOTO991
Let me know the "Machine position for Z1 when you do a normal "Start position" and the "Machining length" from your MC DATA IF this does not work.
Reply with Quote
