Need Help!- post changes

[1234567]

does anybody know how to change my post so my tap cycle looks like this?
this is ridged tap for fanuc 21 i

N135 T05 M06
N137 G90 G54 X0. Y-3.1496
N138 G43 H05 Z2. M08
N138 M29 S200
N139 G84 G98 X0. Y-3.1496 Z-1.0362 R.1 F11.82
N140 X6.7716
N141 X10.1574
N142 G80
N143 G00 Z2.

[mmc005]

I'm sure one of us can. Can you post what bobcad is outputting so we can see what needs to be changed? How about uploading your post processor also.
Dave

[1234567]

this is what bobcad posts for tapping cycle


N135 T05 M06
N136 S378 M03
N137 G90 G54 X0. Y-3.1496
N138 G43 H05 Z.1 M08
N139 G84 G98 X0. Y-3.1496 Z-1.0362 R.1 F22.3228
N140 X6.7716
N141 X10.1574
N142 G80
N143 G00 Z.1

[1234567]

here is the post file

[BurrMan]

With one change to the standard start of program, I get this:

N04 T01 M06
N05 G90 G54 X0. Y0.
N06 G43 H01 Z2. M08
N07 M29 S504
N08 G81 G98 X0. Y0. Z-.08 R2. F1.0084
N09 G80
N10 Z.1
N11 M09
N12 M05
N13 G00 G91 G28 Z0.
N14 M01

There should be a couple changes to the toolchange area also. Can you post the file that makes the code you posted. (Sorry, dont know how to re-create it so I can be sure I get the same numbers) For instance, my code shows coolant off and spindle off and such. This can be removed but I dont want to if your program doesnt have it for some other reason. Also, to get the end at the z.2 also.

[EDIT] Dave may beat me to it! [EDIT]

[mmc005]

It looks like Burr already has the fix for you. Burr, if you put 3 points on your drawing with the first being at X0.0 Y-3.1496, the second one at the same Y position and X6.7716 and the third one at X10.1574. Then when you select your geometry select all three points and then regenerate your program, your numbers and program should look like his first post.
Also, can you post the processor file for him?
Thanks Burr,

Dave

[BurrMan]

Thanks Dave! I suppose if I look at that then I may be able to figure it out!

Heres what that posted. a default tap.

N04 T01 M06
N05 G90 G54 X0. Y-3.1496
N06 G43 H01 Z.1 M08
N07 M29 S504
N08 G81 G98 X0. Y-3.1496 Z-.08 R.1 F1.0084
N09 X6.7716
N10 X10.1574
N11 G80
N12 Z.1
N13 M09
N14 M05
N15 G00 G91 G28 Z0.
N16 M01

The M29 and S was moving a line in the "standard start of program" and "tool changes" areas. (hard coded the M29 in)







Also, the starting Z param is contolled in the feature edit called "Rapid Plane". Put the 2 there. The end Z is inserted by the post. Ive always wondered why it over rides the rapid plane set it the feature edit though.

Anybody else here?



The post is attatched. This one appears to be a bit different than your with some Coolent On/Off Spindle On/Off at end of programs and tool changes. This should be fairly clear though.

[mmc005]

Any time Burr, nice job.

Dave

[1234567]

looks good for the tap cycle but it adds the m29 code for all tools.
m29 sets the machine for ridged tap and that wont work for the rest of the tools.ya i know im a pain in the ##%%^# lol.

[The One]

Do you need any other options than the M29 for the start? That is to say, will it always be the M29?

Regards

[1234567]

m29 is only for g84 tapping cycle.this code sets up ridged tap.i only want m29in the tapping cycle nowhere else.

N135 T05 M06
N137 G90 G54 X0. Y-3.1496
N138 G43 H05 Z2. M08
N138 M29 S200 (only for tapping)
N139 G84 G98 X0. Y-3.1496 Z-1.0362 R.1 F11.82
N140 X6.7716
N141 X10.1574
N142 G80
N143 G00 Z2.


N116 T04 M06
N117 S946 M03 (for every other tool )
N118 G90 G54 X0. Y-3.1496
N119 G43 H04 Z2. M08
N120 G73 G98 X0. Y-3.1496 Z-1.1015 R.1 Q.169 F3.
N121 X6.7716
N122 X10.1574
N123 G80
N124 G00 Z2.

[1234567]

also predator editor does not like the m29.Is there a way to have it skip that block during simulation?as soon as it gets to a line with m29 it stops back plotting the program.