N40 G0 G90 G54 X6.268 Y-12.021M3 T225
N80 G43 H5 Z25.
N100 G1 G41 D0 X6.975 Y-11.314
N110 G0 Z5.
N120 G1 Z-34.
N130 X12.632 Y-5.657
N140 G3 X14.975 Y0. R8.
N150 X-14.975 R14.975
N160 X14.975 R14.975
N170 X12.632 Y5.657 R8.
N190 G0
N200 G0 Z25.
N210 X-10000.
N100 is a move to the start of lead in with cuttercomp using offset#0 ( most use the same # as the tool # for length and dia offsets )
(H0 and D0 usually are zero and are not changeable )
it then rapids down to the clearance plane, feeds into the job (note!! no feedrate applied - should be XY Feedrare on the G41 line , and Plunge rate on the Z)
N140 and N170 are your arc lead in/outs
you seem o be missings the lead out line and a cutter comp cancel (G40), without this you may get errors going to the next point
We have set our order of doing profiles as:-
-set co-ord system
-rapid to start point ( usually 1st point of lead in line )
-set spindle RPM , start spindle
-rapid descent to clearance plane and take up tool length offset
-coolant on
-Rapid to Retract plane
-feed to Z depth
-take up comp ( onto the 2nd point of lead in line )
-lead in arc ( if required )
-do profile
-lead out out ( if required )
-lead out line, cancel comp on last point
-rapid retract or do next depth ( depends on your settings )
Our Okuma's require a line to take up and cancel comp on  |